8.4.10. Contacts and Body Interactions

*CONTACT_AUTOMATIC_GENERAL

Specifies friction or frictionless contacts between line bodies (beams). This keyword is created if the contact is specified using Body Interactions and the geometry contains line bodies.

All the parameter cards are the same as in *CONTACT_AUTOMATIC_SINGLE_SURFACE.

*CONTACT_AUTOMATIC_NODES_TO_SURFACE

Specifies nodes-to-surface friction or frictionless contacts. This keyword is created if the contact is specified using a Contact Region and the Behavior is set to Asymmetric.

Card1 - mandatory

Parameter Card2 and Card3 is the same as in *CONTACT_AUTOMATIC_SINGLE_SURFACE.

*CONTACT_AUTOMATIC_SINGLE_SURFACE

Specifies friction or frictionless contacts between parts. This keyword is created if the contact is specified using Body Interactions.

Card1 - mandatory

Card2 - mandatory

Card3 - mandatory, left blank for defaults to be used.

Card A is the same as for *CONTACT_AUTOMATIC_SURFACE_TO_SURFACE.

*CONTACT_AUTOMATIC_SURFACE_TO_SURFACE

Defines specific surface-to-surface friction or frictionless contacts. This keyword is created if the contact is specified using a Contact Region and the Behavior is set to Symmetric.

Card1 - mandatory

Parameter Card2 and Card3 are the same as in *CONTACT_AUTOMATIC_SINGLE_SURFACE.

Card A

*CONTACT_AUTOMATIC_SURFACE_TO_SURFACE_TIEBREAK

Specifies breakable symmetric bonded contacts. This keyword is created for Bonded contact when the Breakable option is set to Stress Criteria and the contact Behavior is set to Symmetric.

Card 1 is the same as in *CONTACT_TIED_SURFACE_TO_SURFACE_OFFSET.

Card2 - mandatory

Card3 - mandatory, is left blank.

Card A is the same as for *CONTACT_AUTOMATIC_SURFACE_TO_SURFACE.

*CONTACT_ONEWAY_AUTOMATIC_SURFACE_TO_SURFACE_TIEBREAK

Specifies breakable asymmetric bonded contacts. This keyword is created for Bonded contact when the Breakable option is set to Stress Criteria and the contact Behavior is set to Asymmetric.

Parameter cards are the same as in *CONTACT_AUTOMATIC_SURFACE_TO_SURFACE_TIEBREAK.

Card A is not used for this keyword.

*CONTACT_TIED_NODES_TO_SURFACE_OFFSET

Specifies non breakable asymmetric bonded contacts. This keyword is created for Bonded contacts that are not designated as Breakable whose Behavior is set to Asymmetric. This keyword is not used for Body Interactions as these types of contacts are always symmetric.

Card1 - mandatory

Card 2 left blank.

Card 3

*CONTACT_TIED_SURFACE_TO_SURFACE_OFFSET

Specifies general non-breakable bonded contacts that are symmetric. This keyword is created for Bonded and non-breakable contacts which are defined by Contact Regions that are Bonded, non-breakable and whose Behavior is set to Symmetric.

Card1 - mandatory

Cards 2 and 3 are the same as in *CONTACT_TIED_NODES_TO_SURFACE_OFFSET.

Card A is the same as for *CONTACT_AUTOMATIC_SURFACE_TO_SURFACE.

*CONSTRAINED_SPOTWELD

Specifies spot welds between non-contiguous nodal pairs of shell elements. This keyword is created when a spot weld contact is defined in the Mechanical application.

Card

8.4.10.1. Keywords Created from the Contact Properties Object

the use of the Contact Properties object of the Workbench LS-DYNA toolbar Part/Section allows to modify the default generated values ( the type of the contact ) and specify additional values.

*CONTACT_ERODING_SINGLE_SURFACE is written if the contact is specified using a body interaction.

The following keywords are written if the contact is specified using a contact region, and the indicated conditions exist.

*CONTACT_ERODING_NODES_TO_SURFACE is written if the contact Properties Type Section is set to Eroding and the contact is asymmetric.

*CONTACT_ERODING_SURFACE_TO_SURFACE is written if the contact Properties Type Section is set to Eroding and the contact is symmetric.

*CONTACT_FORMING_SURFACE_TO_SURFACE is written if the contact Properties Type Section is set to Forming and the contact is asymmetric.

*CONTACT_FORMING_ONE_WAY_SURFACE_TO_SURFACE is written if the contact Properties Type Section is set to Forming and the contact is asymmetric.

*CONTACT_FORMING_NODES_TO_SURFACE is written if the contact Properties Type Section is set to Forming and the contact is asymmetric, and the scoped entities on the slave side are edges.

The cards for these contact keywords are as follows:

Card1

  • BT = Birth Time from the Common Controls section of the Contact Properties object.

  • DT = Death Time from the Common Controls section of the Contact Properties object.

  • SFS = Slave Penalty Scale Factor from the Common Controls section of the Contact Properties object.

  • SFM = Master Penalty Scale Factor from the Common Controls section of the Contact Properties object.

  • SST = Optional Thickness for Slave Surface from the Advanced Controls section of the Contact Properties object.

  • MST = Optional Thickness for Master Surface from the Advanced Controls section of the Contact Properties object.

  • DEPTH = Depth from the Advanced Controls section of the Contact Properties object.

Card A is also modified

  • SOFT = Soft Constraint Formulation from the Advanced Controls section of the Contact Properties object.

  • SOFTSCL = Soft Constraint Scale Factor from the Advanced Controls section of the Contact Properties object.

If the contact type is set to Eroding, additional parameters are available to support this formulation.

  • ISYM = Symmetry Plane Option from the Erosion Controls section of the Contact Properties object.

  • IADJ = Erosion Node Option from the Erosion Controls section of the Contact Properties object.

  • EROSOP = Solid Elements Treatment from the Erosion Controls section of the Contact Properties object.

*CONTACT_FORCE_TRANSDUCER_PENALTY

When single surface contacts are used, one or more force transducers are added via the *CONTACT_FORCE_TRANSDUCER_PENALTY command. A force transducer does not produce any contact forces and allows you to monitor the contact forces on a subset of parts of the models.

A force transducer is added for each body involved in a body interaction (Frictionless or Frictional).

*CONSTRAINED_LAGRANGE_IN_SOLID

Release 18.2 - © ANSYS, Inc. All rights reserved.