Defines geometry bodies.
Card1
HEADING = name of the body specified in the Workbench environment.
Card2
PID = ID of the part. It is set in the LS-DYNA solver and does not reflect the ID specified in the mesh definition of the model.
SECID = ID of the section keyword associated with the part (see *SECTION).
MID = ID of the material keyword associated with the part (see *MAT).
EOSID = ID of the equation of state associated with the material of this part (*EOS and *MAT). If there is no EOS keyword associated with this part then this parameter is set to 0.
HGID = ID of the hourglass keyword associated with the part (see *HOURGLASS). If there is no hourglass keyword associated with this part then this parameter is set to 0.
Defines cross sectional properties for beam, truss, spot weld and cable elements.
Card1
SECID = ID of the section.
ELFORM = 1 or 2 (default). ELFORM = 2 is set for user defined cross sections. The default element formulation option can be changed by using the Section Object of Workbench LS-DYNA Toolbar Part/Section.
SHRF = 0.833 (default).
QR = 0, which LS-DYNA defaults to 2, quadrature rule is 2x2 Gauss. If the cross sectional area of the beam is complex or user-defined, this parameter becomes IRID and is assigned the negative value of the IRID parameter in the corresponding *INTEGRATION_BEAM keyword (see above for details).
CST = 2 for solid cross sections nand hollow cross sections (arbitrary user defined integration rule).
Card2
for solid types or hollow cylinders
TS1 = width of beam. This refers specifically to the dimension at node 1.
TS2 = TS1. This refers specifically to the dimension at node 2.
TT1 = 1. Height of beam. This refers specifically to the dimension at node 1. Set to zero for circular solids.
TT2 = TT1. This refers specifically to the dimension at node 2. Set to zero for circular solids. These parameters are overwritten by the *INTEGRATION_BEAM defined for these types.
for general symmetric types
A = cross-sectional area.
ISS = Iyy, moment of inertia about the local s-axis.
ITT = Izz, moment of inertia about the local t-axis.
IST = Iyz.
J = Ixx.
The use of the Section object of the Workbench LS-DYNA toolbar Part/Section allows you to modify the default generated values.
In presence of line Bodies:
ELFORM = LS-DYNA ID from the Definition section of the Section object. This field is read only; the actual value of the element formulation is set by the Formulation section of the Section object.
If the formulation is one of the following, the Card is calculated similarly to the above definition for *SECTION_BEAM, and an *INTEGRATION_BEAM is written:
Hughes -Liu with cross section integration
Integrated warped beam
Belytschko Schwer full cross-section integration
Belytschko Schwer tubular beam with cross-section integration
If the formulation is one of the following:
Belytschko Schwer resultant beam (resultant)
Truss (resultant)
Belytschko Schwer full cross-section integration
Card 2 is modified and uses the syntax for the alternative form for formulations 2, 3, and 12.
STYPE is calculated from the section type defined in ANSYS DesignModeler or SpaceClaim.
D1 - D6 are calculated from the dimensions defined in ANSYS DesignModeler.
If the formulation is Discrete/ Beam Cable, an additional panel is available:
A material Card (*MAT_LINEAR_ELASTIC_DISCRETE_BEAM) is added to allow definition of properties for the discrete Beam.
This card replaces the material defined in Engineering and its properties are calculated from it and the above panel.
MID = ID of material type, must be unique between the material keyword definitions.
RO = Density of the Material
TKR = Longitudinal Stiffness X from Discrete and Cable Controls
TKS = Longitudinal Stiffness Y from Discrete and Cable Controls
TKT = Longitudinal Stiffness Z from Discrete and Cable Controls
RKR = Torsional Stiffness X from Discrete and Cable Controls
RKS = Torsional Stiffness X from Discrete and Cable Controls
RKT = Torsional Stiffness X from Discrete and Cable Controls
This card replaces the material defined in Engineering Data and its properties are calculated from it, and the above panel.
MID = ID of material type, must be unique between the material keyword definitions.
RO = Density of the Material
E = Young Modulus of the Material
A material Card (*MAT_CABLE_DISCRETE_BEAM) is added to allow definition of properties for the discrete Beam.
Defines section properties for shell elements.
Card1
SECID = ID of the section.
ELFORM = 2 (default).
SHRF = 0.8333 (default).
NIP = 3 (default).
Card2
T1 = thickness of body.
T2-T4 = T1, shell thickness at nodes 2, 3 and 4.
The use of the Section object of the Workbench LS-DYNA toolbar Part/Section allows you to modify the default generated values.
In the presence of Surface Bodies:

ELFORM = LS-DYNA IDfrom the Definition section of the Section object. This field is read only; the actual value of the element formulation is set by the Formulation section of the Section object.
NIP = Through Thickness Integration Points from the Definition section of the Section object.
Defines section properties for solid elements.
Card
SECID = ID of the section.
ELFORM =
1 (default). Also, used for first-order hexahedral elements, 5-noded pyramids, 6-noded wedges or bodies with mixed element types that include tetrahedrons together with hexahedrons, pyramids, or wedges.
10 if elements are first-order tetrahedrons.
16 if the elements are second-order tetrahedrons.
The use of the Section object of the Workbench LS-DYNA toolbar Part/Section allows you to modify the default generated values.
In the presence of Solid Bodies:

ELFORM = LS-DYNA IDfrom the Definition section of the Section object. This field is read only; the actual value of the element formulation is set by the Formulation section of the Section object.
This keyword is written when you use the Section object of the Workbench LS-DYNA toolbar Part/Section, which allows you to modify the default generated values for the *SECTION keyword. If the ALE section from the Definition of the Section object is set to Yes.

ELFORM = LS-DYNA ID from the Definition section of the Section object. This field is read only; the actual value of the element formulation is set by the Formulation section of the Section object. If LS-DYNA ID is zero, ELFORM is set to 5 (1 Point ALE ).
Available Formulations are the following :
1 point ALE : ELFORM = 5
1 point Eulerian : ELFORM = 6
1 point Eulerian ambient : ELFORM = 7
1 point ALE Multi-Material Element : ELFORM = 11
1 point Integration with single material and void : ELFORM = 12
Card 2
AFAC = Simple Average from the ALE Controls of the Section object. Smoothing weight factor - Simple average.
BFAC = Volume Weighting from the ALE Controls of the Section object. Smoothing weight factor - Volume Weighting
CFAC = Isoparametric Weighting from the ALE Controls of the Section object.
DFAC = Equipotential Weighting from the ALE Controls of the Section object
AAFAC = Advection Factor from the ALE Controls of the Section object
START = start from the ALE Time Controls of the Section object.
END = end from the ALE Time Controls of the Section object.
Defines hourglass and bulk viscosity properties that are referenced in the *PART keyword via its HGID parameter (see *PART keyword).
This keyword can be written using the Section object of the Workbench LS-DYNA toolbar object Part/Hourglass Control, which allows you to specify body scoped hourglass definition.

HGID = ID of the part. It is set in the LS-DYNA solver and does not reflect the ID specified in the mesh definition of the model.
IHQ = Hourglass Control Type.
QM = Hourglass from the Coefficients section of the Hourglass Control object.
Q1 = Quadratic Bulk from the Coefficients section of the Hourglass Control object.
Q2 = Linear Bulk from the Coefficients section of the Hourglass Control object.
IBQ = 1 Standard LS-DYNA Bulk Viscosity
This keyword can also be created using the Keyword Snippet(also, Commands objects) for the LS-DYNA solver. To use it, insert a Keyword Snippet under a Geometry body in the Tree Outline. The program will automatically substitute the HGID parameter in accordance with the *PART keyword of the associated body. All other parameters in the Keyword Snippet are transcribed literally.
If the keyword is entered in a Keyword Snippet anywhere else in the Tree Outline, it will be exported literally. This practice is not recommended, however, and a warning is provided in the header of Keyword Snippet objects when detected.
This keyword is used for reinforcements body interactions.
SLAVE is set to the ID of the component containing line bodies
Master is set to the ID of the component containing solid bodies
Specifies rigid bodies to be merged into one part. The resulting Part ID matches the ID of the rigid body designated as the master.
By constraining the rigid bodies together using a single multibody part you avoid specifying conflicting motion on the nodes shared among the rigid bodies. All boundary conditions applied to the master body will also be applied to all the slave bodies as well. Any boundary conditions that were applied to the slaves will be ignored.
The object Master Rigid Body allows you to specify the master rigid body.
Card
PIDM = ID of the master rigid body.
PIDS = ID of the slave rigid body.