2.6. Define Connections

For general information about defining connections, see Define Connections in the ANSYS Mechanical User's Guide.

Line body to line body contact is possible subject to the following:

Reinforcement body interaction should be supported in the case when only line bodies are scoped to a Body Interaction of Type = Reinforcement. The line bodies will then be tied to any solid body that they intersect. Reinforcement body interactions are not supported for Workbench LS-DYNA or for 2D Explicit Dynamics analyses. However utilizing Keyword Snippets under Contact Region objects should provide a suitable alternative.

Body Interactions, Contact and Spot Welds are all valid in Explicit Dynamics analyses. Frictional, Frictionless and Bonded body interactions and contact options are available. Conditionally bonded contact can be simulated using the breakable property of each bonded region. Spot Welds can also be made to fail using the breakable property.

Joints and Beam connections are not supported for Explicit Dynamics analyses. Springs are not supported for Workbench LS-DYNA analyses. The Contact Tool is also not applicable to Explicit Dynamics analyses.

For Workbench LS-DYNA, bonded body interactions are not supported. Also, Contact Region objects with Auto Asymmetric Behavior or just Asymmetric Behavior are treated the same. Symmetric Behavior will create a _SURFACE_TO_SURFACE keyword for the contact and an Asymmetric Behavior will create a _NODES_TO_SURFACE keyword.

For Workbench LS-DYNA, contacts between line bodies and solids can be implemented using the Keyword Snippets facility available under the Manual Contact Region objects.

Bonded contact is not supported in an Explicit Dynamics analysis for bodies that have their Reference Frame set to Eulerian (Virtual). A solver warning is shown to let the user know that such bodies will be ignored for bonds. Bonded contact is not support in a 2D Explicit Dynamics analysis.

To avoid hourglassing problems, remote points can be used if there are only a few nodes active in the bond definition.

Bonds are not recommended for joining tetrahedral meshes. Use multibodied parts or remote points instead.

By default, a Body Interaction object will be automatically inserted in the Mechanical application tree and will be scoped to all bodies in the model. This object activates frictionless contact behavior between all bodies that come into proximity during the analysis.


Release 18.2 - © ANSYS, Inc. All rights reserved.