Extrude(Operation, BaseObject, Direction,
Extent, Depth, Extent2, Depth2, Walled, Thin1, Thin2)
Note that some combinations of arguments may not be valid. The restrictions are the same as when creating an Extrude interactively.
Operation: This is also referred
to as Material Types.
It refers to the desired operation
agc.Add |
agc.Cut |
agc.Slice |
agc.Imprint |
agc.Frozen |
BaseObject: An existing base
object
Direction: Which way, or ways
to extrude
agc.DirNormal |
agc.DirReversed |
agc.DirSymmetric |
agc.DirAsymmetric |
Extent: Primary extrude type
agc.ExtentFixed |
agc.ExtentThruAll |
agc.ExtentToNext |
Depth: Depth or distance if
Extent is agc.ExtentFixed. This is used for both directions if Direction
is agc.DirSymmetric.
Extent2: Second extrude type
if Direction is agc.DirAsymmetric. Possible values are the same as
Extent.
Depth2: Depth or distance if
Direction is agc.DirAsymmetric and Extent2 is agc.ExtentFixed.
Walled: Switch for thin solids
or surfaces
agc.Yes |
agc.No |
Thin1: Thickness inside profile
Thin2: Thickness outside profile
Note that the acceptable values for these properties are shown above. The same restrictions and argument types apply here as when creating the Extrude.
Name
Operation
Direction
Extent
Extent2
Depth
Depth2
Walled
Thin1
Thin2
MergeTopology (This is set to agc.Yes by
default)
PutBaseObject (BaseObject):
Allows you to change the base object of the extrude. The base object
should be an existing sketch, plane outline, or named selection.
//Create Extrude of Sketch1, 35 units in the +Z direction var ext1 = agb.Extrude(agc.Add, ps1.Sk1, agc.DirNormal, agc.ExtentFixed, 35.0, agc.ExtentFixed, 0.0, agc.No, 0.0, 0.0); agb.Regen(); //To insure model validity //Now, make some changes to the Extrude //Change to Sketch2 as the base object, extrude 20 units in both directions and name it ext1.PutBaseObject(ps1.Sketch2); ext1.Name = "OvalExtrude"; ext1.depth = 20; ext1.Direction = agc.DirSymmetric; agb.Regen(); //To process the changes and insure model validity