
The following table shows the format and details of each of the fields.
Note:
The order of the keys is not important in the file.
All the units are in SI.
is the type of simulation you have chosen. Here it
is set to "combustion”.
is the sub type of combustion simulation you have
chosen. Here it is set to "full_engine_full_cycle”.
is the engine speed, which will be used along with crank angle step size to calculate the time step size.
will be used to calculate the time step. 0.25 is a good default value.
∆t=θ/6N(RPM)
is the crank radius in meter when the piston is at the Bottom Dead Center (BDC) position.
is piston offset value in meter.
is the distance till which the layering part of the mesh will move as a rigid body. After this it will stop moving, but the piston head will continue to move until it reaches BDC. Thus the layering process will begin from the cutoff distance. This is required to create a large enough space in the upper part of the cylinder, that is meshed with tetrahedra. It ensures that the valves can fully move in that zone and the smoothing and remeshing process can happen. This value along with the value of are used to control the actual values of the valve lift and piston stroke, such that:
νlift = max (vclift, vminlift)
ps = min (pcs, pmins)
is the length of the connecting rod in meters.
takes the floating numerical value of the minimum valve lift in meters. Fluent assumes that once you have set up the mesh topology, the mesh topology is unchanged throughout the entire simulation. Therefore, Fluent does not allow you to completely close the valves such that the cells between the valve and the valve seat degenerate (become flat cells) when these surfaces come in contact. (Removing these flat cells would require the creation of new boundary face zones). To prevent this collapse, you need to define a minimum valve lift and Fluent will automatically stop the motion of the valve when the valve lift is smaller than the minimum valve lift value.
is set to Boolean #t or #f. This will be used to deactivate some of the fluid
zones which are not part of the simulation.
will take the value #t or #f, depending on whether the engine has symmetry defined
or not.
will take the value #t if
the mesh topology is the default ICE topology.
takes the format of (x y z). If symmetry is defined, you have to provide the normal at the given
point.
takes the format of (x y z). If symmetry is defined, you have to provide a point on the symmetry.
takes the input "h" or "l" with quotes. If you are opting for a hybrid mesh
i.e. layering in the valve region and combination of re-meshing and
layering in the cylinder and dome region, you need to set it as "h". If you are opting for a layered mesh in the valve,
dome, and the cylinder region, then you need to set it as "l".
takes the input "n" or “c” (with quotes) depending on whether
the mesh has non conformal interfaces ("n") or conformal ("c" ) interfaces.
takes the Boolean value #t or #f, and will be used to define proper
interfaces.
will be used in the case of a hybrid approach. It
takes input 1 or 3. 1 is for straight valve, or canted valve
engine with chamber decomposition. 3 is used
for straight or canted valve engines, without chamber decomposition.
In the case of layered approach this value will not be used.
is the number of valves in the setup valve list.
takes the input in the form of (x y z). It is the axis of the cylinder.
takes the input in the form of (x y z). It signifies the point of origin of the cylinder axis.
is the radius of the cylinder in meters.
Values of cylinder axis, origin, and radius are used to define the rigid body motion for the piston and also for remeshing of the dynamic cylinder zone.
is the angle at which decomposition takes place. It
is set to 0 by default.
is used to insert an interior zone in case of canted or straight valve engines without chamber decomposition. This is in the case where there is no initial layering zone.
is used to delete the interior zone inserted by the insert_angle.
is a reference value. Some global and local mesh setting values are dependent on this term. This term is used to set layering height for , , and bodies.
For layer height is equal to (0.4 X ).
For and layer height is equal to (0.8 X ).
contains all the information related to valve in the format shown.
((Valve-Index “Valve-Name”
“Valve-Profile-Name” Valve-Open-Angle Valve-Close-Angle
(valve Axis vector) (Valve origin coordinates) Variable-urf? Variable-timestep?
(smoothing #t) (end-valve-open-smoothing 384.4) (begin-valve-close-smoothing
528.7))(Valve-Index ……..))
If the
field Variable-urf? is #t Fluent automatically increases and decreases the URF (under relaxation
factors) values of the flow.
Similarly
if Variable-timestep is #t Fluent will modify the time step during valve openings.
If smoothing is set to #t, solver
will only do smoothing while valve is opening, till reaching the crank
angle end-valve-open-smoothing. (Here for the you have set it to 384.4). Also solver will stop layering and start smoothing while closing
the valve at begin-valve-close-smoothing.
(In this example it for the it
is set at 528.7 degrees).