13.1.2. Meshing Procedure for Cold Flow Simulation

There are two ways to generate the mesh.

Meshing directly from the Workbench Window

After decomposition is done you can then directly generate the mesh from the Workbench window without opening the ANSYS Meshing application. If you want to use the default mesh settings then right-click on the Mesh cell and select Update from the context menu. This will first create the mesh controls and then generate the mesh.

You can also change the mesh settings from the Workbench window.

In the Properties box which is displayed after selecting the Mesh cell you can click on Edit Mesh Settings next to the Mesh Settings property, under IC Engine. This will open a ICEngine Mesh Settings dialog box.

You can change the settings for the parameters:

Meshing using ANSYS Meshing Application

In this method of meshing you can check the mesh controls and settings in details.

  1. Double-click the Mesh cell in the IC Engine analysis system to open the ANSYS Meshing application.

  2. Click IC Setup Mesh (  located in the IC Engine toolbar). This opens the IC Mesh Parameters dialog box.

    1. Here you can define different mesh settings for the different parts.

      In the IC Mesh Parameters dialog box you can see the default mesh settings. You can change the settings or use the default ones.

      • Mesh Type: You can select Fine, Medium, or Coarse from the drop-down list. The default setting is Medium.

      • Reference Size: This is a reference value. Some global mesh settings and local mesh setting values are dependent on this term.

        Reference Size = (Valve margin perimeter) /100


        Note:  Choosing Fine, Medium, or Coarse changes the Reference Size and thus all other dependent parameters are also affected.


      Global Mesh Settings

      • Min Mesh Size: This value is set to Reference Size/3.

      • Max Mesh Size: This value is set to Reference Size × 3. This can be parametrized by enabling the check box next to it.


      Note:  If Reference Size is changed, all the other parameters will change, depending on their relation with it.


    2. If after changing the values of the parameters you would like to go back to the default values, click Reset.

    3. Click OK to set and close the IC Mesh Parameters dialog box.

    You can generate the mesh controls before opening ANSYS Meshing application. To do this enable Automatically Setup On Edit under IC Engine in the Properties box which is displayed after selecting the Mesh cell in the Workbench window.

    So after you double-click the Mesh cell to open ANSYS Meshing application the mesh controls are already set.

  3. Click IC Generate Mesh (  located in the IC Engine toolbar) to generate the mesh.

After you click IC Generate Mesh (  a mesh is created and exported.


Note:  If you want to modify any of the mesh control parameters, you can change them even after the mesh is generated, by clicking IC Setup Mesh(  ) icon. You will have to create the mesh again with the changed settings.


13.1.2.1. Global Mesh Settings for Cold Flow Simulation

IC Engine meshing tool creates Global Mesh Settings based on the information provided in the IC Mesh Parameters dialog box. Following section describes these settings:

For more information on Global Mesh Settings, see Global Mesh Controls in the Meshing User's Guide.

13.1.2.1.1. Sizing Group

Under the Details of Mesh, the following are the global mesh settings defined under Sizing.

  • Size Function: Since CFD is chosen as the Physics Preference, this parameter is set to Curvature for Cold Flow Simulation.

    This option provides greater control over sizing functions. The option chosen determines which refinement mechanisms are activated in the Advanced Size Function.

  • Relevance Center: It is set to Coarse.

    This sets the gauge of the Relevance slider control in the Default group. The default value can be set automatically according to the Physics Preference.

  • Smoothing: It is set to Medium.

  • Span Angle Center: It is set to Fine.

    This sets the goal for curvature based refinement. The mesh will subdivide in curved regions until the individual elements span this angle. The following choices are available:

    • Coarse — 91o to 60o

    • Medium — 75o to 24o

    • Fine — 36o to 12o

  • Min Size: It is equal to the value of Min Mesh Size, which is set in the IC Engine Mesh Parameters dialog box.

  • Max Face Size: It is equal to the value of Max Mesh Size, which is set in theIC Engine Mesh Parameters dialog box.

  • Max Size: It is equal to the value of Max Mesh Size set in the IC Engine Mesh Parameters dialog box.


Release 18.2 - © ANSYS, Inc. All rights reserved.