If you want to use the case file generated by IC Engine system and run the simulation in standalone Fluent, you should read the scheme file (WB-ICE-Solver-Setup.scm) after you read the case file in Fluent. This is mandatory. Else you will get some errors while running.
Important: The report () may not be properly generated if you run the simulation in standalone Fluent.
In the cold flow simulation case,
if the cyl-tri or symm-cyl-tri face zone contains a curvature then it might result in smaller elements
at the curve. See Figure 16.12: Curvature in cyl-tri .
In such cases if you are facing “Negative Volume
Cell" errors while running the mesh motion or computation, then enabling remeshing option both globally and locally
for those face zones will improve the solver stability. To enable
local face remeshing in Fluent:
Go to in the navigation pane.
Click under .
In the dialog box click the tab and enable .

Click and close the dialog box.
Select the cyl-tri and symm-cyl-tri (in case of symmetry) face zone from the list and click .
In the dialog box click the tab.
Enable in the group box.

Click and close the dialog box.
In some cold flow or combustion cases cyl-tri and symm-cyl-tri mesh might be stretched as shown in the figure below, due to failure of remeshing in cyl-tri and symm-cyl-tri.

This is mainly because of the small kinks in the piston faces. To avoid this problem, you need to enable the following options manually:
Enable the "Local Face" remeshing both globally as well as locally for cyl-tri and symm-cyl-tri zones as shown in troubleshooting point above.
Note: You cannot enable Local Face remeshing in all cases because it affects the cycle to cycle mesh repeatability.
Enable zone-remeshing through following TUI:
/define/dynamic-mesh/controls/remeshing-parameters/zone-remeshing
yes
Note: You cannot enable zone remeshing for all cases — In parallel, the zone remeshing will automatically migrate all elements to be remeshed to a single CPU. Consequently, the machine memory will limit the size of the zone that can be remeshed.
In case you get a negative volume error during computation —
Check the mesh. If you observe that the zone motion is not happening properly, then in the DesignModeler check that the named selections are having proper supports, especially near the chamber and piston areas.
If you have used Kegrids, check that the replaced mesh has the same order of selection of valve bodies as per the originally decomposed mesh. Else, after mesh replace valve-ch is swapped, leading to negative volume.
When you select from the drop-down list in the dialog box, then is set to some value, say “X”. In Fluent in the task page is set to , but the case and data are saved at the frequency “X” which you have set.
If you take the ICEngine system generated case file to standalone Fluent and run the simulation without reading the ICEngine scheme file (WB-ICE-Solver-Setup.scm) then the case and data will be saved at every time step. To avoid this problem and to make sure that case and data get saved at requested frequency “X” (), you will have to read ICEngine scheme file WB-ICE-Solver-Setup.scm before reading the case file in standalone Fluent. If this is not done then the case and data files will be saved on the frequency set in , which is 1 by default.
During remeshing if you observe denser cells near piston regions while the piston is moving upwards or skewness is increasing, then you need to increase the in the tab of the dialog box in Fluent. This will help in improving the mesh, but it might increase the mesh motion time. It has been observed that values between 50 to 150 for are more effective.