If you select the MultiZone Quad/Tri method, a mesh of quads and/or triangles is created over the entire part of the selected body, depending on values that you enter for the options described below.
MultiZone Quad/Tri is a patch independent method. See Patch Independent for more information.
Surface Mesh Method - Instructs MultiZone Quad/Tri to use the , , or method to create the mesh.
- Automatically uses a combination of and mesh methods depending on the mesh sizes set and face properties. This is the default method.
- Uses a recursive loop-splitting method which creates a highly uniform mesh. This option is generally good when all edges have the same sizing and the faces being meshed do not have a high degree of curvature. The orthogonality of the mesh from this method is generally very good.
- Uses a paving mesh method which creates a good quality mesh on faces with high curvature, and also when neighboring edges have a high aspect ratio. This approach is also more reliable to give an all-quad mesh.
Note: The MultiZone Quad/Tri method ignores the Size Function when Surface Mesh Method is set to . In such cases, Element Size acts as a hard size.
Note: Models created in versions of ANSYS older than ANSYS 14.5 that have a MultiZone Quad/Tri mesh method (previously named Uniform Quad/Tri or Uniform Quad) defined on them will be resumed in ANSYS 14.5 with the Surface Mesh Method set to Uniform so that the mesh is similar to what it was in previous versions. You might want to set the Surface Mesh Method to Program Controlled for better results.
When resuming these models, the Method control that appears in the Details View will be set to MultiZone Quad/Tri, but the old mesh method name (Uniform Quad/Tri Method or Uniform Quad Method) will appear in the Tree Outline. To avoid confusion, it may be helpful to force the software to rename the mesh method object in the Tree Outline. To do so, set Method to a different value (for example, Quadrilateral Dominant) and then reset Method to MultiZone Quad/Tri. In some cases, you may also see messages containing references to the old mesh method names. The names in the messages will be updated to the new names if/when you remesh.
Element Order - Refer to Method Controls and Element Order Settings.
Free Face Mesh Type - Determines the shape of the mesh elements. Can be All Quad, All Tri, or Quad/Tri (default) for a mesh of pure quad, pure tri, or a combination of quad/tri elements respectively.
Element Size - Allows you to specify the element size used for the selected geometry. Applicable only when Surface Mesh Method is set to . Otherwise, uses the global Element Size.
Mesh Based Defeaturing - “Filters” edges in/out based on size and angle. Can be On or Off. By default, this local Mesh Based Defeaturing setting is the same as the setting of the global Mesh Defeaturing control. When Mesh Based Defeaturing is On, a Defeature Size field appears where you may enter a numerical value greater than 0.0. By default, the value of this local Defeature Size field is the same as the global Defeature Size. If you specify a different value here, it will override the global value. A recommended setting is at least one-half the value set for Element Size to assure a successful mesh. Specifying a value of 0.0 here resets the tolerance to its default.
Note: When the global Mesh Defeaturing control is on but the Size Function is Adaptive, the default defeaturing performed for MultiZone Quad/Tri includes defeaturing based on the dihedral angle between the faces as well as edge length defeaturing based on the smallest element size set by the user.
Sheet Loop Removal - Removes holes on surface bodies based on size. If set to Yes, a Loop Removal Tolerance field appears where you may enter a numerical value greater than 0.0. By default, the value of this local Loop Removal Tolerance field is the same as the global Loop Removal Tolerance. If you specify a different value here, it will override the global value. The mesh simply paves over holes smaller than the Loop Removal Tolerance setting. Holes with boundary conditions applied to them will not be removed from the mesh. Any boundary conditions applied to holes that were removed from the mesh will not be respected by the solver.
Minimum Edge Length - Read-only indication of the smallest edge length in the part.
Write ICEM CFD Files - Sets options for writing ANSYS ICEM CFD files. Refer to Writing ANSYS ICEM CFD Files for details.
The following usage information is applicable to the MultiZone Quad/Tri mesh method:
This control is sensitive to the scoping of all other objects in Workbench. If you add a load or support to a group of faces, the part with this mesh method control may need to be remeshed. If you change the scoping of the load, the part may need to be remeshed if the faces or edges are not captured by the mesh. The mesh however, is not made obsolete when adding or changing the scoping of a result. It is recommended that you apply loads to the model before meshing when using this mesh method. See Patch Independent for more information.
Base mesh caching is not supported for MultiZone Quad/Tri, so a change to inflation controls requires remeshing.
Using MultiZone Quad/Tri may allow meshing over very small bodies in a multibody part. This may lead to a solver error if a body load is associated with that body. If this is the case, you must suppress the body before solving your model.
Surface bodies with specified variable thickness are not protected topology. To prevent faces and their boundaries from being meshed over, create an individual Named Selection for each thickness.
The MultiZone Quad/Tri mesh method supports mesh connections.
You can use the MultiZone Quad/Tri mesh method in combination with other surface mesh methods in a multibody part, and the bodies will be meshed with conformal mesh. If you select the MultiZone Quad/Tri mesh method to mesh a multibody part that contains a mix of line bodies and surface bodies, all surface bodies and all line bodies that share edges with surface bodies will be meshed with the selected method. Any remaining line bodies (where only vertices are shared with surface bodies) will be meshed with the Quadrilateral Dominant mesh method. Refer to Conformal and Non-Conformal Meshing for more information about conformal meshing.
When meshing multibody parts having solid bodies and sheet bodies with some faces shared, it is best to mesh the shared faces with MultiZone Quad/Tri. If the faces are meshed using the solid body mesh method control, the MultiZone Quad/Tri body will often fail.
Caution: Multiple environments with different loadings may over-constrain the MultiZone Quad/Tri mesher such that the mesher may not be able to return a mesh for the given inputs. If discretization error is not an issue, the mesher will be less constrained if you duplicate the model and change the environment instead of adding multiple environments under the same model.