MultiZone Quad/Tri Method Control

If you select the MultiZone Quad/Tri method, a mesh of quads and/or triangles is created over the entire part of the selected body, depending on values that you enter for the options described below.

MultiZone Quad/Tri is a patch independent method. See Patch Independent for more information.

Surface Mesh Method - Instructs MultiZone Quad/Tri to use the Program Controlled, Uniform, or Pave method to create the mesh.


Note:  The MultiZone Quad/Tri method ignores the Size Function when Surface Mesh Method is set to Uniform. In such cases, Element Size acts as a hard size.



Note:  Models created in versions of ANSYS older than ANSYS 14.5 that have a MultiZone Quad/Tri mesh method (previously named Uniform Quad/Tri or Uniform Quad) defined on them will be resumed in ANSYS 14.5 with the Surface Mesh Method set to Uniform so that the mesh is similar to what it was in previous versions. You might want to set the Surface Mesh Method to Program Controlled for better results.

When resuming these models, the Method control that appears in the Details View will be set to MultiZone Quad/Tri, but the old mesh method name (Uniform Quad/Tri Method or Uniform Quad Method) will appear in the Tree Outline. To avoid confusion, it may be helpful to force the software to rename the mesh method object in the Tree Outline. To do so, set Method to a different value (for example, Quadrilateral Dominant) and then reset Method to MultiZone Quad/Tri. In some cases, you may also see messages containing references to the old mesh method names. The names in the messages will be updated to the new names if/when you remesh.


Element Order - Refer to Method Controls and Element Order Settings.

Free Face Mesh Type - Determines the shape of the mesh elements. Can be All Quad, All Tri, or Quad/Tri (default) for a mesh of pure quad, pure tri, or a combination of quad/tri elements respectively.

Element Size - Allows you to specify the element size used for the selected geometry. Applicable only when Surface Mesh Method is set to Uniform. Otherwise, uses the global Element Size.

Mesh Based Defeaturing - “Filters” edges in/out based on size and angle. Can be On or Off. By default, this local Mesh Based Defeaturing setting is the same as the setting of the global Mesh Defeaturing control. When Mesh Based Defeaturing is On, a Defeature Size field appears where you may enter a numerical value greater than 0.0. By default, the value of this local Defeature Size field is the same as the global Defeature Size. If you specify a different value here, it will override the global value. A recommended setting is at least one-half the value set for Element Size to assure a successful mesh. Specifying a value of 0.0 here resets the tolerance to its default.


Note:  When the global Mesh Defeaturing control is on but the Size Function is Adaptive, the default defeaturing performed for MultiZone Quad/Tri includes defeaturing based on the dihedral angle between the faces as well as edge length defeaturing based on the smallest element size set by the user.


Sheet Loop Removal - Removes holes on surface bodies based on size. If set to Yes, a Loop Removal Tolerance field appears where you may enter a numerical value greater than 0.0. By default, the value of this local Loop Removal Tolerance field is the same as the global Loop Removal Tolerance. If you specify a different value here, it will override the global value. The mesh simply paves over holes smaller than the Loop Removal Tolerance setting. Holes with boundary conditions applied to them will not be removed from the mesh. Any boundary conditions applied to holes that were removed from the mesh will not be respected by the solver.

Minimum Edge Length - Read-only indication of the smallest edge length in the part.

Write ICEM CFD Files - Sets options for writing ANSYS ICEM CFD files. Refer to Writing ANSYS ICEM CFD Files for details.

Usage Information for the MultiZone Quad/Tri Mesh Method Control

The following usage information is applicable to the MultiZone Quad/Tri mesh method:


Caution:  Multiple environments with different loadings may over-constrain the MultiZone Quad/Tri mesher such that the mesher may not be able to return a mesh for the given inputs. If discretization error is not an issue, the mesher will be less constrained if you duplicate the model and change the environment instead of adding multiple environments under the same model.



Release 18.2 - © ANSYS, Inc. All rights reserved.