Finding Contacts

You can use the Find Contacts option as a diagnostics tool to locate contacts in an assembly. By default, Find Contacts detects face-edge contacts using a tolerance based on the current Min Size/Proximity Min Size (whichever is smaller) as follows:

The search for contacts passes feature information down to the meshing algorithm to ensure that desired features are preserved. In addition to the edges that are determined to be feature edges based on the assembly meshing angle criterion, edges referenced in contact regions are also considered as feature edges in assembly meshing. Find Contacts is particularly useful for assemblies in which fillets of bodies are adjacent to other bodies, forming a sharp angle, as it will preserve the edges of these fillets independent of the feature angle settings.

Find Contacts uses the Mechanical application's technology for automatic connection detection to provide these diagnostics for assembly meshing. The technology generates diagnostics data in the form of contact regions for the contacts automatically. Each contact region is named appropriately based on the names of the items in the Geometry branch of the tree that make up that contact region (for example, Bonded - Solid_2 To Solid_4).

Be aware that from the perspective of the Mechanical application, the connection detection technology is dependent on physics properties. When the technology is used for assembly meshing diagnostics, physics properties are not considered.

Connection detection options that are of particular importance to finding contacts for assembly meshing are mentioned below. They are set optimally by default to provide assembly meshing diagnostics and should not be changed.

If you are interested in learning more about connection detection settings and how they are used by the Mechanical application, refer to Common Connections Folder Operations for Auto Generated Connections in the Mechanical help.

The Find Contacts option is available only when assembly meshing algorithms are being used.

The steps for using the Find Contacts option are presented here.

  1. Make sure that Min Size/Proximity Min Size is set appropriately.

  2. Highlight the Mesh object or Connections object in the Tree Outline.

  3. Do one of the following:

    • Click the right mouse button on the object and select Find Contacts from the context menu.

    • Click the right mouse button on the Geometry window and select Find Contacts from the context menu.

    Either of these methods inserts an Assembly Meshing Contacts folder beneath the Connections object and populates it with appropriately named contact regions.


    Note:  If Find Contacts does not find any contacts that meet the tolerance criteria, the folder is inserted but it will be empty.


    The figure below shows the default settings that appear in the Details View when the Assembly Meshing Contacts folder is selected. The defaults should not be changed.

    • The Tolerance Value is set to 10% of the value of Min Size/Proximity Min Size which for this example was set to 0.250 mm.

    • Face/Edge is set to Yes to detect contacts between faces and edges.

    • Group By is set to Bodies, meaning connection faces and edges that lie on the same bodies will be included in a single connection object.

    • Search Across is set to Bodies, enabling automatic connection detection between bodies.


Note:  If you change Min Size/Proximity Min Size, you must rerun the option to regenerate the data. Each time you rerun the option an additional folder is added to the Tree Outline (i.e., Assembly Meshing Contacts 2, Assembly Meshing Contacts 3, and so on). The lowest folder in the tree contains the most recent data.



Release 18.2 - © ANSYS, Inc. All rights reserved.