Finding Thin Sections

You can use the Find Thin Sections option as a diagnostics tool to locate thin sections in an assembly. By default, Find Thin Sections looks for all sections with a size equal to or less than the current Min Size/Proximity Min Size (whichever is smaller).

Find Thin Sections uses the Mechanical application's technology for automatic connection detection to provide these diagnostics for assembly meshing. The technology generates diagnostics data in the form of contact regions for the thin sections automatically. Each contact region is named appropriately based on the names of the items in the Geometry branch of the tree that make up that contact region (for example, Bonded - Solid_3 To Solid_3).

Be aware that from the perspective of the Mechanical application, the connection detection technology is dependent on physics properties. When the technology is used for assembly meshing diagnostics, physics properties are not considered.

Connection detection options that are of particular importance to finding thin sections for assembly meshing are mentioned below. They are set optimally by default to provide assembly meshing diagnostics and should not be changed.

If you are interested in learning more about connection detection settings and how they are used by the Mechanical application, refer to Common Connections Folder Operations for Auto Generated Connections in the Mechanical help.

The Find Thin Sections option is available only when assembly meshing algorithms are being used. Use of the Find Thin Sections option is an optional step in the assembly meshing workflow.

The steps for using the Find Thin Sections option are presented here.

  1. Make sure that Min Size/Proximity Min Size is set appropriately.

  2. Highlight the Mesh object or Connections object in the Tree Outline.

  3. Do one of the following:

    • Click the right mouse button on the object and select Find Thin Sections from the context menu.

    • Click the right mouse button on the Geometry window and select Find Thin Sections from the context menu.

    Either of these methods inserts an Assembly Meshing Thin Sections folder beneath the Connections object and populates the folder with appropriately named contact regions.


    Note:  If Find Thin Sections does not find any thin sections that meet the tolerance criteria, the folder is inserted but it will be empty.


    The figure below shows the default settings that appear in the Details View when the folder is selected. The defaults should not be changed.

    • The Tolerance Value is based on the value of Min Size/Proximity Min Size, which was set to 0.250 mm for this example.

    • Face/Face is set to Yes to detect thin sections between faces.

    • Group By is set to Parts, meaning connection faces that lie on the same parts will be included in a single connection object.

    • Search Across is set to Anywhere, enabling automatic connection detection regardless of where the geometry lies. Contacts that occur across bodies are deleted automatically (see note below).


Note:
  • If you change Min Size/Proximity Min Size, you must rerun the option to regenerate the data. Each time you rerun the option an additional folder is added to the Tree Outline (i.e., Assembly Meshing Thin Sections 2, Assembly Meshing Thin Sections 3, and so on). The lowest folder in the tree contains the most recent data.

  • The Find Thin Sections option automatically deletes contacts that occur across bodies (for example, from Body_A to Body_B).



Release 18.2 - © ANSYS, Inc. All rights reserved.