ANSYS ICEM CFD Export

When you export from the Meshing application to ANSYS ICEM CFD format, an ANSYS ICEM CFD project file with the extension .prj, along with a geometry file (*.tin) and/or mesh file (*.uns) are written. The files that are created are the same as those that are created if you begin in ANSYS ICEM CFD and use its Workbench Readers option to import a file from the Meshing application.

Anytime you plan to export from the Meshing application to ANSYS ICEM CFD format, it is best practice to define the desired part and body names for your model in the DesignModeler application prior to meshing the model in the Meshing application. This is recommended because the ANSYS ICEM CFD part names will be derived from the part and body names that are defined for the model when you initially open the model in the Meshing application; the export process will ignore any renaming or Named Selections created in the Meshing application.

There are three ways to export meshing data to ICEM CFD format:

  1. Choose File> Export from the Meshing application main menu, then Save as type ICEM CFD Input Files.

    ANSYS ICEM CFD part names that appear in the exported files are derived from the ANSYS Workbench geometry part and body names. In the case of a single body part, only the body name is used.


    Note:  The concept of a part in ANSYS Workbench and a part in ANSYS ICEM CFD is not the same. For information about parts in ANSYS Workbench, refer to Conformal and Non-Conformal Meshing in the Meshing application help and Geometry Introduction in the Mechanical help. For information about parts in ANSYS ICEM CFD, refer to the documentation available under the Help menu within ANSYS ICEM CFD.


  2. Save your ANSYS Workbench files (*.mechdat or *.meshdat) and use the ANSYS ICEM CFD File > Workbench Readers option to import the files into ANSYS ICEM CFD (as long as ANSYS Workbench and ANSYS ICEM CFD are installed on the same machine). Legacy formats such as *.dsdb and *.cmdb are also supported.

    Any defined Named Selections will be imported into ANSYS ICEM CFD as subsets because subsets support non-exclusive sets (overlapping Named Selections). However, each entity can only be in a single part (exclusive sets). In cases where you want overlapping Named Selections to be converted to ANSYS ICEM CFD parts, the overlapping subsets can be cleaned up in ANSYS ICEM CFD and then converted into parts. For details about handling imported ANSYS Workbench files in ANSYS ICEM CFD, refer to the documentation available under the Help menu within ANSYS ICEM CFD.

  3. Use the ANSYS ICEM CFD Workbench Add-In. In ANSYS Workbench, right-click on a Geometry or Mesh cell and choose Transfer Data Into New > ICEM CFD.  The advantage of the Add-In connection is that it maintains the connectivity once the geometry is modified so, unlike the previous two methods, you can easily refresh the geometry in ICEM CFD and then update the mesh and the solver input. For more information, see Component Systems in the [ANSYS Workbench User's Guide].

Rules Followed By the Export Process

When exporting to ANSYS ICEM CFD format, these rules are followed:


Note:  The series of examples that follows this list illustrates many of the rules listed here.


The first example is a model consisting of four separate single body parts in ANSYS Workbench. The single body parts are named fluid1, fluid2, fluid3, and fluid4. The table below shows the geometry in ANSYS Workbench and the corresponding part names that will appear in ANSYS ICEM CFD:

This geometry in ANSYS Workbench...Results in these part names in ANSYS ICEM CFD...
A model consisting of four separate single body parts named: 
fluid1FLUID1_1
fluid2FLUID2_2
fluid3FLUID3_3
fluid4FLUID4_4

The figure below shows the model after it was meshed in the Meshing application:

Figure 13:  Meshed Model (Four Separate Workbench Parts) Ready for Export to ANSYS ICEM CFD

Meshed Model (Four Separate Workbench Parts) Ready for Export to ANSYS ICEM CFD

Next, the model was exported from the Meshing application to ANSYS ICEM CFD format. In the figure below, the corresponding .prj file has been opened in ANSYS ICEM CFD. Notice the names that are assigned to the various entities in the ANSYS ICEM CFD format file:

Figure 14:  Opening the .prj File (Four Separate Workbench Parts) in ANSYS ICEM CFD

Opening the .prj File (Four Separate Workbench Parts) in ANSYS ICEM CFD

The second example is a model consisting of one multibody part in ANSYS Workbench. The multibody part, which is named Part 4, contains four bodies named fluid1, fluid2, fluid3, and fluid4. The table below shows the geometry in ANSYS Workbench and the corresponding part names that will appear in ANSYS ICEM CFD:

This geometry in ANSYS Workbench...Results in these part names in ANSYS ICEM CFD (the / character denotes hierarchy)...
A model consisting of one multibody part named Part 4, containing four bodies named: 
fluid1PART_4_1/FLUID1_3
fluid2PART_4_1/FLUID2_2
fluid3PART_4_1/FLUID3_1
fluid4PART_4_1/FLUID4_4

Figure 15:  Meshed Model (One Multibody Workbench Part) Ready for Export to ANSYS ICEM CFD

Meshed Model (One Multibody Workbench Part) Ready for Export to ANSYS ICEM CFD

Next, the model was exported from the Meshing application to ANSYS ICEM CFD format. In the figure below, the corresponding .prj file has been opened in ANSYS ICEM CFD. Notice the names that are assigned to the various entities in the ANSYS ICEM CFD format file:

Figure 16:  Opening the .prj File (One Multibody Workbench Part) in ANSYS ICEM CFD

Opening the .prj File (One Multibody Workbench Part) in ANSYS ICEM CFD

The third (and final) example involves a model for which four Named Selections are defined in the DesignModeler application. The model is meshed in the Meshing application, exported to ANSYS ICEM CFD format, and opened in ANSYS ICEM CFD.

The first figure shows the model after it was meshed in the Meshing application.

Figure 17:  Meshed Model (with Named Selections) Ready for Export to ANSYS ICEM CFD

Meshed Model (with Named Selections) Ready for Export to ANSYS ICEM CFD

The next four figures show the entit(ies) in the model that are contained in each of the four Named Selections. In the figure below, the Fluid1_Fluid2 Named Selection is highlighted.

Figure 18:  Fluid1_Fluid2 Named Selection

Fluid1_Fluid2 Named Selection

In the figure below, the InterfaceSolidFluid2 Named Selection is highlighted.

Figure 19:  InterfaceSolidFluid2 Named Selection

InterfaceSolidFluid2 Named Selection

In the figure below, the SharedEdge Named Selection is highlighted.

Figure 20:  SharedEdge Named Selection

SharedEdge Named Selection

In the figure below, the SharedVertices Named Selection is highlighted.

Figure 21:  SharedVertices Named Selection

SharedVertices Named Selection

Next, the model was exported from the Meshing application to ANSYS ICEM CFD format. In the figure below, the corresponding .prj file has been opened in ANSYS ICEM CFD. Notice the names that are assigned to the various entities in the ANSYS ICEM CFD format file:

Figure 22:  Opening the .prj File (with Named Selections) in ANSYS ICEM CFD

Opening the .prj File (with Named Selections) in ANSYS ICEM CFD


Note:  For additional information, refer to the documentation available under the Help menu within ANSYS ICEM CFD.



Release 18.2 - © ANSYS, Inc. All rights reserved.