The options that appear in the right pane of the Options dialog box depend on which category is selected in the left pane:
When Meshing is selected in the left pane, these subcategories appear:
Meshing
Virtual Topology
Sizing
Deprecated Sizing
Quality
Inflation
When Export is selected in the left pane, these subcategories appear:
CGNS
ANSYS Fluent
Highlight Topology Being Meshed if Possible: Controls the default for highlighting of topologies during mesh processing. When Yes (default), the topology that is currently being processed by the mesher is highlighted in the Geometry window, which may help with troubleshooting. This highlighting is not supported for the Patch Independent Tetra or MultiZone mesh methods, or when assembly meshing is being used. Refer to Generating Mesh for details.
Allow Selective Meshing: Allows/disallows selective meshing. Choices are Yes and No. The default value is Yes. Refer to Selective Meshing for details.
Number of CPUs for Meshing Methods: Specifies the number of processors to be used by the meshing operation. There is no counterpart setting in the Details View. Specifying multiple processors will enhance the performance of the MultiZone Quad/Tri, Patch Independent Tetra, and MultiZone mesh methods. This option has no effect when other mesh methods are being used. You can specify a value from 0 to 256 or accept the default. The default is 0, which means the number of processors will be set automatically to the maximum number of available CPUs. The Number of CPUs option is applicable to shared memory parallel (SMP) meshing (multiple cores; not supported for clusters). Refer to Parallel Part Meshing.
Default Physics Preference: Sets the default option for the Physics Preference in the Details View of a Mesh object. Choices are Mechanical, Nonlinear Mechanical, Electromagnetics, CFD, Explicit, and Hydrodynamics.
Default Method: Sets the default Method setting in the Details View of a Method control object. This option only affects Method controls that are added manually. Choices are Automatic (Patch Conforming/Sweeping), Patch Independent, and Patch Conforming. When the geometry is attached, the default method of all options except Automatic will be scoped to all parts in the assembly. The Automatic option has no effect.
Note: Changing the Default Method changes the default mesh method for all future analyses, regardless of analysis type.
Use MultiZone for Sweepable Bodies: If set to On, the mesher uses the MultiZone method instead of General Sweeping for sweepable bodies. The default setting is Off. See MultiZone for Sweepable Bodies for more information.
Topology Checking: Sets the default value for the Topology Checking control. The default value is No.
Verbose Messages from Meshing: Controls the verbosity of messages returned to you. If set to and you are meshing a subset of bodies, the message “These bodies are going to be meshed” appears, and you can click the right mouse button on the message to see the bodies. The default is . Regardless of the setting, when meshing completes and any bodies failed to mesh, the message “These bodies failed to be meshed” appears, and you can click the right mouse button to see them.
Number of CPUs for Parallel Part Meshing: Sets the default number of processors to be used for parallel part meshing. You can change this value in the group under the Details View. Using the default for specifying multiple processors will enhance meshing performance on geometries with multiple parts. For parallel part meshing, the default is set to Program Controlled or 0. This instructs the mesher to use all available CPU cores. The Default setting inherently limits 2 GB memory per CPU core. An explicit value can be specified between 0 and 256, where 0 is the default. Refer to Parallel Part Meshing for more details.
Merge Edges Bounding Manually Created Faces: Sets the default value for the Merge Face Edges setting in the Details View of a Virtual Topology object. Choices are Yes and No. The default value is Yes.
Simplified Mesh Sizing UI: Enables or disables the simplified user interface for mesh sizing. Choices are Yes and No. The default value is No. Refer to Meshing with the Simplified Mesh Sizing UI for details.
Mechanical Min Size Factor (Default: 0.01): Sets your preference for the scale factor that will be used to calculate the default minimum size when the physics preference is Mechanical, Electromagnetics, or Explicit. The value that is specified here is multiplied by the global element size to determine the default minimum size.
CFD Min Size Factor (Default: 0.01): Sets your preference for the scale factor that will be used to calculate the default minimum size when the physics preference is CFD. The value that is specified here is multiplied by the global element size to determine the default minimum size.
Defeature Size Factor (Default: 0.005): Sets your preference for the scale factor that will be used to calculate the default defeature size. The value that is specified here is multiplied by the global element size to determine the default defeature size.
MultiZone Sweep Sizing Behavior: If set to Use Size Function, then any applied sizing controls (curvature and proximity refinement, and/or local sizing) are evaluated in all directions of the selected bodies. If set to Ignore Size Function, curvature and proximity refinement and/or local sizing along the sweep path are ignored and the spacing along the sweep path is determined either by the global sizes or local sizes that are explicitly set on edges along the sweep direction.
You can also override the size function by locally specifying hard edge sizes or using the Sweep Size Behavior control in the MultiZone method control to locally adjust the sizing for the bodies the control is scoped to. See MultiZone Method Control for more information.
Relevance: Allows setting of the default mesher, known as relevance. The Details View default is 0, but it can be changed here. The range is from -100 (high speed solution, coarser mesh, less accuracy) to +100 (slower speed solution, finer mesh, higher accuracy).
Number of Retries: Sets the default for the Number of Retries control in the group under the Details View. Refer to Number of Retries for details.
Size Function: Sets the default value for the Size Function setting in the Details View of a Mesh object. Choices are (the default), , , , and .
Check Mesh Quality: Sets the default quality behavior with respect to how the mesher responds to error and warning limits. Choices are:
Default - With this setting, the behavior changes as appropriate when you change the setting of Physics Preference.
Yes, Errors - If the meshing algorithm cannot generate a mesh that passes all error limits, an error message is printed and meshing fails.
Yes, Errors and Warnings - If the meshing algorithm cannot generate a mesh that passes all error limits, an error message is printed and meshing fails. In addition, if the meshing algorithm cannot generate a mesh that passes all warning (target) limits, a warning message is printed.
No - Mesh quality checks are done at various stages of the meshing process (for example, after surface meshing prior to volume meshing). The No setting turns off most quality checks, but some minimal checking is still done. In addition, even with the No setting, the target quality metrics are still used to improve the mesh. The No setting is intended for troubleshooting and should be used with caution as it could lead to solver failures or incorrect solution results.
Mechanical Error Limit: Sets the default error limit when Physics Preference is set to Mechanical. Choices are Standard Mechanical and Aggressive Mechanical.
Target Quality (0 = Program Default): Sets the default target element quality. When you modify this value, the value you enter becomes the new default for the Target Quality in the Details View. You can enter 0 on the Options panel to revert to the program default.
Target Skewness (0 = Program Default): Sets the default target skewness. When you modify this value, the value you enter becomes the new default for the Target Skewness in the Details View. You can enter 0 on the Options panel to revert to the program default. For a tetrahedral mesh, you should not set Target Skewness to a value < 0.8.
Target Jacobian Ratio (Corner Nodes) (0 = Program Default): Sets the default target Jacobian ratio. When you modify this value, the value you enter becomes the new default Target Jacobian Ratio (Corner Nodes) in the Details View. You can enter 0 on the Options panel to revert to the program default.
Inflation-related options that can be set on the Options dialog box include:
File Format: Sets the file format to be used for CGNS Export operations. There is no counterpart setting in the Details View. Choices are:
(default) - Exports the mesh in ADF (Advanced Data Format).
- Exports the mesh in HDF5 (Hierarchical Data Format version 5).
CGNS Version: Sets the CGNS library version to be used for CGNS Export operations. There is no counterpart setting in the Details View. Choices are (the default), , , , , , and .
Export Unit: Defines the unit of measurement for the mesh when exported to CGNS. The default is Use Project Unit, which means the mesh is not scaled. If you change this to another value (centimeter, millimeter, micrometer, inch, or foot), the mesh is scaled according to the export unit you select.
Format of Input File (*.msh): Sets the file format to be used for Fluent Mesh Export operations. There is no counterpart setting in the Details View. Choices are (the default) and .
Auto Zone Type Assignment: When set to On (the default), zone types are automatically assigned, as described in Fluent Mesh Export. When set to Off, assigns all boundary zones as the default WALL, enabling you to assign your own zone type assignments for Fluent Mesh Export operations.