3.3. Fluent Remote Console Example

This example illustrates a typical sequence in which Fluent Remote Console is used to connect to a running Fluent Server session and perform a remote simulation. It will demonstrate the following basic tasks:


Note:  This example presumes that a Fluent Server session is running on a local or remote machine. For details on starting a Fluent Server session, see Starting Fluent In Server Mode.


Example Procedure

  1. Start Fluent Remote Console using one of the methods in Using the Fluent Remote Console.

    C:\>"\Program Files\ANSYS Inc\v182\fluent\fluent18.2.0\launcher\win64\flconsole"
  2. Connect to a running Fluent Server session (fsm.connect_to_session).

    Because a filename was not specified with the fsm.connect_to_session command, a dialog box opens to select the aaS_FluentId.txt file.

    After clicking Open, Fluent Remote Console reports the connection status and lists available parameters. In this example, no case file is loaded in the Fluent session, so no parameters are available.

  3. Load a case file from the local (client) machine (fluent.load_case).

    Because a filename was not specified with the fluent.load_case command, a dialog box opens to select the case file.

    Fluent Remote Console reports that the case has been loaded. Note that we use the fluent.load_case command which uploads the case file to the server machine prior to it being read into Fluent.

    The case is loaded into the Fluent session. In this case, the Fluent session was started with graphics enabled so it displays the mesh as it would if running interactively.

  4. Retrieve the current parameter values (fluent.list_parameters).

    This case has 3 parameters defined: input MachNumber, and outputs Drag and Lift.

    There is not yet any solution data, so Drag and Lift values are reported as 0.000000.

  5. Initialize the solution (TUI Command solve initialize hyb-initialization).

  6. Iterate the solution (TUI Command solve iterate 200).

    Fluent iterates until convergence is reached and prints the iteration information to the Fluent output window.

  7. Get the values of Drag and Lift (fluent.get_parameter).

  8. Change the value of MachNumber and Pressure relaxation (fluent.set_parameter, fluent.retrieve_rpvars_info, fluent.list_rpvars_wildcards, fluent.set_rpvar).


    Note:  You must use fluent.retrieve_rpvars_info to update the available rpvars from Fluent before listing the rpvars for the first time, and any time that new rpvars are created.


    This case uses the Coupled Pressure-Based solver with Pseudo Transient relaxation, so the rpvar pressure-coupled/pressure/pseudo-explicit-relax is chosen.

  9. Direct output to the Fluent Output window and update the solution (fluent.set_silent, solve iterate 200).

  10. Report the values of Drag and Lift at MachNumber = 0.7.

  11. Save the case and data files to the client machine (fluent.save_case, fluent.save_data).

    Since no filename was specified to fluent.save_case a dialog box opens for you to select a location. The fluent.save_data command is performed the same way. Note that fluent.save_case and fluent.save_data allow you to save the case/data files to the local (client) machine.

  12. Terminate the Fluent session (fluent.terminate).


Release 18.2 - © ANSYS, Inc. All rights reserved.