ANSYS Fluent can import one or more flamelet files, convolute these diffusion flamelets with the assumed-shape PDFs (see Equation 8–43), and construct look-up tables. The flamelet files can be generated in ANSYS Fluent, or with separate stand-alone computer codes.
The following types of flamelet files can be imported into ANSYS Fluent:
Standard format files described in Standard Files for Diffusion Flamelet Modeling in the User's Guide and in Peters and Rogg [377]
When diffusion flamelets are generated in physical space, the species and temperature vary in one spatial dimension. The species and temperature must then be mapped from physical space to mixture fraction space. If the diffusion coefficients of all species are equal, a unique definition of the mixture fraction exists. However, with differential diffusion, the mixture fraction can be defined in a number of ways.
ANSYS Fluent computes the mixture fraction profile along the diffusion flamelet in one of the following ways:
Read from a file (standard format files only)
This option is for diffusion flamelets solved in mixture fraction space. If you choose this method, ANSYS Fluent will search for the mixture fraction keyword Z, as specified in Peter and Roggs’s work [377], and retrieve the data. If ANSYS Fluent does not find mixture fraction data in the flamelet file, it will instead use the hydrocarbon formula method described below.
Hydrocarbon formula
Following the work of Bilger et al. [40], the mixture fraction is calculated as
(8–50) |
where
(8–51) |
,
, and
are the mass fractions of carbon, hydrogen, and oxygen atoms, and
,
, and
are the molecular weights.
and
are the values of
at the oxidizer and fuel inlets.
The flamelet profiles in the multiple-flamelet data set should vary only in the strain rate imposed; the species and the boundary conditions should be the same. In addition, it is recommended that an extinguished flamelet is excluded from the multiple-flamelet data set. The formats for multiple diffusion flamelets are as follows:
Standard format: If you have a set of standard format flamelet files, you can import them all at the same time, and ANSYS Fluent will merge them internally into a multiple-flamelet file. When you import the set of flamelet files, ANSYS Fluent will search for and count the occurrences of the HEADER keyword to determine the number of diffusion flamelets in the file.
CFX-RIF format: A CFX-RIF flamelet file contains multiple diffusion flamelets at various strains and the file should not be modified manually. Only one CFX-RIF flamelet file should be imported.
For either type of file, ANSYS Fluent will determine the number of flamelet profiles and sort them in ascending strain-rate order. For diffusion flamelets generated in physical space, you can select one of the four methods available for the calculation of mixture fraction. The scalar dissipation will be calculated from the strain rate using Equation 8–42.