For multiphase turbulent flows using the Eulerian model, ANSYS Fluent can include the effects of turbulent dispersion forces which account for the interphase turbulent momentum transfer. The turbulent dispersion force acts as a turbulent diffusion in dispersed flows. For example for a boiling flow in a heated vertical pipe, vapor is generated on heated wall surfaces. The turbulent dispersion force plays a crucial role in driving the vapor away from the vicinity of the wall towards the center of the pipe.
The turbulent dispersion force arises from averaging the interphase
drag term. For a dispersed phase, , and a continuous phase,
, the turbulent drag is modeled
as:
(17–276) |
The term on the left side is the instantaneous drag. The first
term on the right hand side, , appears in Equation 17–170 and represents the mean momentum
exchange between the two phases.
is the interphase exchange coefficient,
described in Interphase Exchange Coefficients,
and
and
are the mean phase
velocity vectors. The second term,
, is commonly referred to as the turbulent
dispersion force:
(17–277) |
where is the drift velocity and accounts for the dispersion of the secondary
phases due to transport by turbulent fluid motion.
is a factor that can be used to impose a limiting
function on the turbulent dispersion force. For clarity, the limiting
factor is omitted from the descriptions of the turbulent dispersion
models that follow. See Limiting Functions for the Turbulent Dispersion Force for details about
the implementation of the limiting factor.
The following sections describe the models for turbulent dispersion force that are available in ANSYS Fluent:
You can also specify the turbulent dispersion force with a User Defined Function. For information on enabling turbulent dispersion force in your model, see Including the Turbulent Dispersion Force in the User’s Guide.
Instead of following Equation 17–277 and modeling the drift velocity, Lopez de Bertodano proposed the following formulation [289]:
(17–278) |
where is the continuous
phase density,
is the turbulent
kinetic energy in the continuous phase, and
is the gradient of
dispersed phase volume fraction, and
is a user-modifiable constant. By default,
.
Simonin and Viollet [439] proposed that
the drift velocity, , is calculated from:
(17–279) |
In Equation 17–279, is the fluid-particulate dispersion tensor.
For the dispersed two-equation turbulence model (k- ε Dispersed Turbulence Model), ANSYS Fluent uses Tchen theory [185] and assumes that is a scalar, expressed as given by
in Equation 17–379 with a dispersion Prandtl number,
(
by default). The turbulent dispersion force is then given by:
(17–280) |
Here, is a user-modifiable constant that is set to
1 by default.
For the mixture turbulence model (k- ε Mixture Turbulence Model), the dispersion scalar is equal to the mixture turbulent kinematic viscosity.
Burns et al. [65] derived a formulation based on Favre averaging of the drag term. The final expression is similar to Simonin’s model. For the Burns model, the dispersion scalar is estimated by the turbulent viscosity of the continuous phase:
(17–281) |
and
(17–282) |
By default, and
. As in the Simonin model, when using the mixture turbulence model
the dispersion scalar is equal to the mixture turbulent kinetic viscosity.
Instead of treating the turbulent dispersion as an interfacial
momentum force in the phase momentum equations, you can model it as
a turbulent diffusion term in the governing equations of phase volume
fractions [454]. With the turbulent dispersion
term, the governing equation for the volume fraction in phase , Equation 17–167, becomes:
(17–283) |
where is the diffusion
coefficient in the
phase, and the
term
is the turbulent dispersion term that must
satisfy the constraint:
(17–284) |
In order to satisfy Equation 17–284 the diffusion coefficients
for the secondary phases are estimated from the phase turbulent viscosities, as
(17–285) |
where by default.
For the primary phase, , the diffusion term is
(17–286) |
In some applications it is desirable to apply the turbulent
dispersion force only in particular flow regimes or conditions. For
example, a user may want to include the turbulent dispersion force
only in a bubbly flow regime. To accommodate this, a limiting function
can be applied through the factor, , in Equation 17–277.
ANSYS Fluent provides three options for determining :
By default, no limiting is performed on the turbulent
dispersion force ().
ANSYS Fluent includes a standard limiting function that
varies linearly from 0 to 1 based on the volume fraction of the dispersed phase(s), :
(17–287) |
By default,
If necessary, the values of and
can be changed using the following
domainsetvar scheme commands:
| (domainsetvar <phase-id> ‘mp/td/vof-lower-limit < |
| (domainsetvar <phase-id>
‘mp/td/vof-upper-limit < |
with appropriate values substituted for <phase-id>
and <—value>.
Note that the value for <phase-id> for a given phase can be
found from the Phases dialog box in the user
interface.
You can specify your own limiting function by creating
a User-Defined Function (UDF) using the DEFINE_EXCHANGE_PROPERTY macro (DEFINE_EXCHANGE_PROPERTY). Note that must have a value between
0 and 1, and should vary continuously to
ensure numerical stability and physical solutions.