The macros listed in Table 3.21: Macro for Face Centroids Defined in metric.h –
Table 3.24: Macros for Interior and Boundary Face Flow Variables Defined
in mem.h can be used to return real face variables in SI units. They are identified
by the F_ prefix. Note that these variables
are available only in the pressure-based solver.
In addition, quantities that are returned are available only if the
corresponding physical model is active. For example, species mass
fraction is available only if species transport has been enabled in
the Species Model dialog box in ANSYS Fluent. Definitions
for these macros can be found in the referenced header files (for
example, mem.h).
The macro listed in Table 3.21: Macro for Face Centroids Defined in metric.h can
be used to obtain the real centroid of a
face. F_CENTROID finds the coordinate position
of the centroid of the face f and stores
the coordinates in the x array. Note that
the x array is always one-dimensional, but
it can be x[2] or x[3] depending on whether you are using the 2D or 3D solver.
Table 3.21: Macro for Face Centroids Defined in metric.h
| Macro | Argument Types | Outputs |
|---|---|---|
| | | |
The ND_ND macro returns 2 or 3 in 2D
and 3D cases, respectively, as defined in The ND Macros.
DEFINE_PROFILE
contains an example of F_CENTROID usage.
F_AREA can be used to return the real face area vector (or ‘face area normal’)
of a given face f in a face thread t. See
DEFINE_UDS_FLUX
for
an example UDF that utilizes F_AREA.
Table 3.22: Macro for Face Area Vector Defined in metric.h
| Macro | Argument Types | Outputs |
|---|---|---|
| | | |
By convention in ANSYS Fluent, boundary face area normals always point out of the domain. ANSYS Fluent determines the direction of the face area normals for interior faces by applying the right hand rule to the nodes on a face, in order of increasing node number. This is shown in Figure 3.1: ANSYS Fluent Determination of Face Area Normal Direction: 2D Face.
ANSYS Fluent assigns adjacent cells to an interior face (c0 and c1) according to the
following convention: the cell out of which a
face area normal is pointing is designated as cell C0, while the cell in to which a face area normal
is pointing is cell c1 (Figure 3.1: ANSYS Fluent Determination of Face Area Normal Direction: 2D Face). In other words, face
area normals always point from cell c0 to
cell c1.
The macros listed in Table 3.23: Macros for Boundary Face Flow Variables Defined in mem.h access flow variables at a boundary face.
Table 3.23: Macros for Boundary Face Flow Variables Defined in mem.h
| Macro | Argument Types | Returns |
|---|---|---|
| | | u velocity |
| | | v velocity |
| | | w velocity |
| | | temperature |
| | | enthalpy |
| | | turbulent kinetic energy |
| | | turbulent kinetic energy dissipation rate |
| | | species mass fraction |
See
DEFINE_UDS_FLUX
for an example
UDF that utilizes some of these macros.
The macros listed in Table 3.24: Macros for Interior and Boundary Face Flow Variables Defined in mem.h access flow variables at interior faces and boundary faces.
Table 3.24: Macros for Interior and Boundary Face Flow Variables Defined in mem.h
| Macro | Argument Types | Returns |
|---|---|---|
| | | pressure |
| | | mass flow rate through a face |
F_FLUX can be used to return the real scalar mass flow rate through a given face f in a face thread t. The sign
of F_FLUX that is computed by the ANSYS Fluent solver
is positive if the flow direction is the same as the face area normal
direction (as determined by F_AREA - see
Face Area Vector (F_AREA)), and is negative if the flow
direction and the face area normal directions are opposite. In other
words, the flux is positive if the flow is out of the domain, and is negative if the flow is in to the domain.
Note that the sign of the flux that is computed by the solver is opposite to that which is reported in the ANSYS Fluent GUI (for example, the Flux Reports dialog box).
Important: F_P(f,t) is not available in the density-based
solver.
In the density-based solver, F_FLUX(f,t) will only return a value if one or more scalar equations (for example,
turbulence quantities) are being solved that require the mass flux
of a face to be stored by the solver.