You can use DEFINE_DPM_LAW to customize
laws for particles. For example your UDF can specify custom laws for
heat and mass transfer rates for droplets and combusting particles.
Additionally, you can specify custom laws for mass, diameter, and
temperature properties as the droplet or particle exchanges mass and
energy with its surroundings.
When a DEFINE_DPM_LAW UDF is activated,
then the number of species that can be referenced and interact with
the particles via the UDF is limited to those with a species index
less than the maximum UDF species number, defined using the TUI command define/models/dpm/options/maximum-udf-species. The default
number for maximum-udf-species is 50.
DEFINE_DPM_LAW (name, tp, ci)
|
Argument Type |
Description |
|---|---|
|
|
UDF name. |
|
|
Pointer to the |
|
|
Variable that indicates whether the continuous
and discrete phases are coupled (equal to |
Function returns
void
There are three arguments to DEFINE_DPM_LAW: name, tp, and
ci. You supply name, the name of the UDF. tp and ci are variables that are passed by the ANSYS Fluent solver
to your UDF.
Important: Pointer tp can be used as an argument
to the macros defined in DPM Macros to
obtain information about particle properties (for example, injection
properties).
The following UDF, named Evapor_Swelling_Law, models a custom law for the evaporation swelling of particles.
The source code can be interpreted or compiled in ANSYS Fluent. See Example DEFINE_DPM_LAW usage.
/**********************************************************************
UDF that models a custom law for evaporation swelling of particles
***********************************************************************/
#include "udf.h"
DEFINE_DPM_LAW(Evapor_Swelling_Law,tp,ci)
{
real swelling_coeff = 1.1;
/* first, call standard evaporation routine to calculate
the mass and heat transfer */
VaporizationLaw(tp);
/* compute new particle diameter and density */
TP_DIAM(tp) = TP_INIT_DIAM(tp)*(1. + (swelling_coeff - 1.)*
(TP_INIT_MASS(tp)-TP_MASS(tp))/(DPM_VOLATILE_FRACTION(tp)*TP_INIT_MASS(tp)));
TP_RHO(tp) = TP_MASS(tp) / (3.14159*TP_DIAM(tp)*TP_DIAM(tp)*TP_DIAM(tp)/6);
TP_RHO(tp) = MAX(0.1, MIN(1e5, TP_RHO(tp)));
}
After the UDF that you have defined using DEFINE_DPM_LAW is interpreted (Interpreting UDFs)
or compiled (Compiling UDFs), the name
of the argument that you supplied as the first DEFINE macro argument will become visible in the Custom Laws dialog box in ANSYS Fluent. See Hooking DEFINE_DPM_LAW UDFs for details on how to hook your DEFINE_DPM_LAW UDF to ANSYS Fluent.