1.8.1. Pressure-Based Segregated Solver

The solution process for the pressure-based segregated solver (Figure 1.2: Solution Procedure for the Pressure-Based Segregated Solver) begins with a two-step initialization sequence that is executed outside of the solution iteration loop. This sequence begins by initializing equations to user-entered (or default) values taken from the ANSYS Fluent user interface. Next, PROFILE UDFs are called, followed by a call to INIT UDFs. Initialization UDFs overwrite initialization values that were previously set.

The solution iteration loop begins with the execution of ADJUST UDFs. Next, momentum equations for u, v, and w velocities are solved sequentially, followed by mass continuity and velocity updates. Subsequently, the energy and species equations are solved, followed by turbulence and other scalar transport equations, as required. Note that PROFILE and SOURCE UDFs are called by each "Solve" routine for the variable currently under consideration (for example, species, velocity).

After the conservation equations, properties are updated, including PROPERTY UDFs. Thus, if your model involves the gas law, for example, the density will be updated at this time using the updated temperature (and pressure and/or species mass fractions). A check for either convergence or additional requested iterations is done, and the loop either continues or stops.

Figure 1.2:  Solution Procedure for the Pressure-Based Segregated Solver

Solution Procedure for the Pressure-Based Segregated Solver


Release 18.2 - © ANSYS, Inc. All rights reserved.