For automatic mesh partitioning, you can select the partition method and other options for creating the mesh partitions before reading a case file into the parallel version of the solver. For some of the methods, you can perform pretesting to ensure that the best possible partition is performed. See Mesh Partitioning Methods for information about the partitioning methods available in ANSYS Fluent.
Note: Architecturally aware partitioning (see Partitioning) is performed automatically when the case file is read. If the maximum inter-machine communication is reduced by more than 5%, the new partition mapping will be applied, and a message is displayed in the console, for example:
inter-node communication reduction by architecture-aware
remapping: 47%
While the message indicates actual point-to-point network traffic reduction, solver computational performance improvement may be somewhat less, and depends on the case and the system network configuration.
The procedure for partitioning automatically in the parallel solver is as follows:
(optional) Set the partitioning parameters in the Auto Partition Mesh dialog box (Figure 34.6: The Auto Partition Mesh Dialog Box).
Parallel → General → Auto Partition...
If you are reading in a mesh file or a case file for which no partition information is available, and you keep the Case File option turned on, ANSYS Fluent will partition the mesh using the method displayed in the Method drop-down list.
If you want to specify the partitioning method and associated options yourself, the procedure is as follows:
Turn off the Case File option. The other options in the dialog box will become available.
Select the partition method in the Method drop-down list. The choices are the techniques described in Partition Methods.
You can choose to independently apply partitioning to each cell zone, or you can allow partitions to cross zone boundaries using the check button. It is recommended that you not partition cells zones independently (by turning off the check button) unless cells in different zones will require significantly different amounts of computation during the solution phase (for example, if the domain contains both solid and fluid zones).
If you have chosen the Principal Axes or Cartesian Axes method, you can improve the partitioning by enabling the automatic testing of the different bisection directions before the actual partitioning occurs. To use pretesting, turn on the Pre-Test option. Pretesting is described in Pretesting.
Click .
If you have a case file where you have already partitioned the mesh, and the number of partitions divides evenly into the number of compute nodes, you can keep the default selection of Case File in the Auto Partition Mesh dialog box. This instructs ANSYS Fluent to use the partitions in the case file.
Read the case file.
File → Read → Case...
As the mesh is automatically partitioned, some information about the partitioning process will be displayed in the console. If you want additional information, you can display a report from the Partitioning and Load Balancing dialog box after the partitioning is completed.
Parallel → General → Partition/Load Balance...
When you click the or button in the Partitioning and Load Balancing dialog box, ANSYS Fluent will display the partition ID, number of cells, faces, and interfaces, and the ratio of interfaces to faces for each active or stored partition in the console. In addition, it will display the minimum and maximum cell, face, interface, and face-ratio variations. For details, see Interpreting Partition Statistics. You can examine the partitions graphically by following the directions in Checking the Partitions.