The Create/Edit Materials dialog box is used to create and modify materials. Materials can be downloaded from the global database or defined locally. See Physical Properties for details about defining material properties. Using the Create/Edit Materials Dialog Box describes how to use the dialog box.

Controls
shows the name of the material. If you edit this field, the new name will take effect when you click Change/Create.
displays the chemical formula for the material. You should generally not edit this field unless you are creating a material from scratch.
is a drop-down list containing all of the available material types. By default, fluid and solid will be the only choices. If you are modeling species transport/combustion, mixture will also be available. For problems in which you have defined discrete-phase injections, inert-particle, droplet-particle, and/or combusting-particle will also appear.
allows you to choose the fluid material for which you want to modify properties. This option is available when fluid is selected in the Material Type drop-down list.
allows you to choose the solid material for which you want to modify properties. This option is available when solid is selected in the Material Type drop-down list.
allows you to choose the mixture material for which you want to modify properties. This option is available when mixture is selected in the Material Type drop-down list.
allows you to choose the droplet-particle for which you want to modify properties. This option is available when droplet-particle is selected in the Material Type drop-down list.
allows you to order the materials in the Materials list alphabetically by Name or alphabetically by Chemical Formula.
opens the Fluent Database Materials Dialog Box, from where you can copy materials from the global database into the current solver.
opens the Open Database Dialog Box, where you can specify the user-defined database to be used.
contains input fields for the material properties that are required for the active physical models.
sets the material density. You may set a constant value, or select one of the other methods from the drop-down list above the real number field. See Density for instructions on setting density.
sets the constant-pressure specific heat of the material. You may set a constant value, or select one of the other methods from the drop-down list above the real number field. See Specific Heat Capacity for instructions on setting specific heat.
sets the thermal conductivity of the material. You may set a constant value, or select one of the other methods from the drop-down list above the real number field. See Thermal Conductivity for instructions on setting thermal conductivity.
sets the viscosity of the material. You may set a constant value, or select one of the other methods from the drop-down list above the real number field. See Viscosity for instructions on setting viscosity.
sets the molecular weight of the material. It is used to derive the gas constant of the material.
specifies the formation enthalpy of a fluid material for a reacting flow. See Standard State Enthalpies for details.
specifies the standard state entropy of a fluid material for a reacting flow. This input is used only if the fluid material is involved in a reversible reaction. See Standard State Entropies for details.
specifies the reference temperature for the Heat of Formation.
specifies the kinetic theory parameter for a fluid material. See Kinetic Theory Parameters for details.
specifies the kinetic theory parameter for a fluid material. See Kinetic Theory Parameters for details.
specifies the absorption coefficient for radiation heat transfer.
See Radiation Properties for details. If you choose
the wsggm-user-specified option from the drop-down
list next to Absorption Coefficient, the WSGGM User Specified Dialog Box will open. If you choose the user-defined-wsggm option from the drop-down list next
to Absorption Coefficient, the User-Defined Functions Dialog Box will open.
specifies the scattering coefficient for radiation heat transfer (only for the P-1, Rosseland, DO, or MC
radiation models). See Radiation Properties for details.
specifies an isotropic (by default) or linear-anisotropic scattering function. If you are using the DO or MC models, delta-eddington and user-defined scattering functions are also available. See Radiation Properties for details. If you choose delta-eddington, the Delta-Eddington Scattering Function Dialog Box will open.
specifies the refractive index for the material. It is used only when semi-transparent media are modeled with the DO or MC radiation models.
specifies the names of the species that make up a mixture material. To check or modify these names, click the Edit... button to open the Species Dialog Box. This property appears only for mixture materials.
displays the reaction mechanism being used when you are modeling finite-rate reactions. finite-rate appears if LaminarFinite-Rate or Eddy-Dissipation Concept is selected in the Species Model Dialog Box, eddy-dissipation appears if Eddy-Dissipation is selected, and finite-rate/eddy-dissipation appears if Finite-Rate/Eddy-Dissipation is selected.
Click Edit... to open the Reactions Dialog Box.
allows you to enable different reactions selectively in different geometrical zones. Click the Edit button to open the Reaction Mechanisms Dialog Box. See Defining Zone-Based Reaction Mechanisms for details.
contains a drop-down list of available methods for specifying the diffusion coefficients for the species in a mixture material. If you select constant-dilute-appx, you will enter a constant value in the field below. If you select dilute-approx or multicomponent, the Mass Diffusion Coefficients Dialog Box will open, and you can specify the coefficients there. If you select kinetic-theory, you will need to specify the kinetic theory parameters for the individual fluid materials (species) that make up the mixture. See Mass Diffusion Coefficients for details about specifying mass diffusivity.
contains a drop-down list of available methods for specifying the thermal diffusion coefficients for the species in a mixture material. If you select kinetic-theory, you will need to specify the kinetic theory materials (species) that make up the mixture. If you select specified, the Thermal Diffusion Coefficients Dialog Box will open, and you can specify the coefficients there. See Thermal Diffusion Coefficient Inputs for details about specifying thermal diffusion coefficients.
sets the density ( in Equation 9–68
in the Theory Guide) of the unburnt products.
sets the temperature ( in Equation 9–68
in the Theory Guide) of the unburnt products.
(only for adiabatic premixed combustion models)
specifies the value of the burnt products under adiabatic conditions, in Equation 9–65 in the Theory Guide.
specifies the thermal diffusivity ( in Equation 9–9 in the Theory Guide) for use
with the premixed combustion model. See Modeling Premixed Combustion for details.
specifies the value of in Equation 9–9 in the Theory Guide.
specifies the thickness of the flame for which you have a choice of constant, user-defined, or diffusivity-over-flame-speed.
specifies the value of in Equation 9–17 in
the Theory Guide.
(only for non-adiabatic premixed combustion models) specifies the
value of in Equation 9–67 in the Theory Guide.
(only for non-adiabatic premixed combustion models) specifies
the value of in Equation 9–67 in the Theory Guide.
specifies the thermal expansion coefficient ( in Equation 12–3) for use with the Boussinesq approximation.
See Steps in Solving Buoyancy-Driven Flow Problems for details.
specifies the value of the droplet surface tension ( in Equation 16–337 in the Theory Guide).
is
the latent heat of vaporization, ,
required for phase change from an evaporating liquid droplet or for
the evolution of volatiles from a combusting particle. See Setting Material Properties for the Discrete Phase for details.
is the latent heat of vaporization at the normal boiling point, available for droplet-particles. See Using the Cubic Equation of State Models with the Lagrangian Dispersed Phase Models for details.
is given by Equation 7–117. See Using the Cubic Equation of State Models with the Lagrangian Dispersed Phase Models for details.
specifies the thermophoretic coefficient ( in Equation 16–11
in the Theory Guide), and appears when the thermophoretic force is included in the discrete
phase calculation.
is the temperature, , at which the calculation of vaporization from a
liquid droplet or devolatilization from a combusting particle is initiated
by ANSYS Fluent. See Setting Material Properties for the Discrete Phase for details.
is
the temperature, , at which
the calculation of the boiling rate equation is initiated by ANSYS Fluent.
See Setting Material Properties for the Discrete Phase for details.
is the selected approach for the calculation of the vapor concentration of the components at the surface. This can be Raoult’s law (Equation 16–195 in the Theory Guide), the Peng-Robinson real gas model (Equation 16–203 in the Theory Guide), or a user-defined function that provides this value.
() is the fraction of a droplet particle that may
vaporize via Laws 2 and/or 3 (Droplet Vaporization (Law 2) in the Theory Guide). For combusting
particles, it is the fraction of volatiles that may be evolved via
Law 4 (Devolatilization (Law 4) in the Theory
Guide). See Setting Material Properties for the Discrete Phase for
details.
is the mass diffusion coefficient, , used in the vaporization
law, Law 2. This input is also used to define the mass diffusion of
the oxidizing species to the surface of a combusting particle,
. See Setting Material Properties for the Discrete Phase for details.
is the reference pressure for the pressure
dependent binary diffusivity in Equation 16–112 in the Fluent Theory Guide.
is the saturated vapor pressure, , defined as a function of temperature, which is
used in the vaporization law, Law 2. See Setting Material Properties for the Discrete Phase for details.
is the heat of the instantaneous pyrolysis reaction, , that the
evaporating/boiling species may undergo when released to the continuous
phase. The heat of pyrolysis should be entered as a positive number
for exothermic reaction and as a negative number for endothermic reaction.
The default value of zero implies that the heat of pyrolysis is not
considered. See Setting Material Properties for the Discrete Phase for details.
is the
coefficient in Equation 16–205 in the Fluent Theory Guide.
To assume bulk gas composition for the physical properties in the
particle vaporization and heating rates equations, select
none from the Composition Averaging Coefficient drop-down in the Create/Edit Materials dialog
box, under Properties. To enable property averaging,
select constant and enter a value between 0 and
1 for the Composition Averaging Coefficient. = 1 corresponds to bulk gas mixture. For
= 0, the composition reverts to the particle surface
composition.
Important: When you define the Composition Averaging
Coefficient with a constant value
other than 1, you must also specify Specific Heat, Viscosity and Thermal Conductivity for the evaporating species (in the Create/Edit Materials dialog box, under Properties, for the corresponding
fluid material of the continuous phase mixture).
The default and recommended value for the averaging coefficient is 1/3. However, to improve the simulation results, you must provide accurate temperature-dependent data for the vapor material.
is the
coefficient in Equation 16–204 in the Fluent Theory Guide.
To assume bulk gas temperature for the physical properties in the
particle vaporization and heating rates equations, select
none from the Temperature Averaging Coefficient drop-down in the Create/Edit Materials dialog
box, under Properties. To enable property averaging,
select constant and enter a value between 0 and
1 for the Temperature Averaging Coefficient. = 1 corresponds to bulk gas conditions. For
= 0, the temperature reverts to the particle surface
temperature.
Important: When you define the Temperature Averaging
Coefficient with a constant value
other than 1, you must also specify Specific Heat, Viscosity and Thermal Conductivity for the evaporating species (in the Create/Edit Materials dialog box, under Properties, for the corresponding
fluid material of the continuous phase mixture).
The default and recommended value for the averaging coefficient is 1/3. However, to improve the simulation results, you must provide accurate temperature-dependent data for the evaporating vapor material.
defines which vaporization model is used for pure droplets (Law 2) and for multicomponent droplets (Law 7). If you want to use the default diffusion controlled model, retain the selection of diffusion-controlled from the drop-down list to the right of Vaporization Model. This will apply Equation 16–101 in the Theory Guide.
To use the convection/diffusion controlled model for vaporization select convection/diffusion-controlled from the drop-down list. Equation 16–106 in the Theory Guide will be applied for the calculation of the vaporization rate, and Equation 16–118 in the Theory Guide will be applied in the particle heat transfer calculations This model is recommended when evaporation rates are high. For slowly evaporating droplets both models are expected to give similar results.
If you have selected the convection/diffusion-controlled, you can enable the Variable Lewis Number Formulation option in Convection/Diffusion Model Dialog Box to compute the Spalding heat number from Equation 16–117 in the Fluent Theory Guide. If the option is disabled ANSYS Fluent uses Equation 16–118.
specifies the kinetic theory parameter , which is the number of nodes
of energy storage. This parameter is required only if you are defining
specific heat via kinetic theory. See Kinetic Theory Parameters for details.
is the emissivity of particles in your model, , used to compute
radiation heat transfer to the particles when the P-1 or DO radiation
model is active and particle radiation interaction is enabled in the Discrete Phase Model Dialog Box. See Setting Material Properties for the Discrete Phase for details.
is the scattering factor, , due to particles in the P-1 or DO radiation model.
Note that this property will appear only if particle radiation interaction
is enabled in the Discrete Phase Model Dialog Box. See Setting Material Properties for the Discrete Phase for details.
is the coefficient, , which governs
the swelling of the coal particle during the devolatilization law,
Law 4. A swelling coefficient of unity (the default) implies that
the coal particle stays at constant diameter during the devolatilization
process. See Setting Material Properties for the Discrete Phase for details.
is the stoichiometric requirement, , for the burnout
reaction, in terms of mass of oxidant per mass of char in the particle.
See Setting Material Properties for the Discrete Phase for details.
is the mass fraction of char, , in the coal particle (the fraction of the initial
combusting particle that will react in the surface reaction) Law 5.
See Setting Material Properties for the Discrete Phase for details.
is the parameter , which controls
the distribution of the heat of reaction between the particle and
the continuous phase. The default value of zero implies that the entire
heat of reaction is released to the continuous phase. See Setting Material Properties for the Discrete Phase for details.
is the heat released by the surface char combustion reaction, Law 5. This parameter is specified in terms of heat release (for example, Joules) per unit mass of char consumed in the surface reaction. See Setting Material Properties for the Discrete Phase for details.
defines which version of the devolatilization model, Law 4,
is being used. If you want to use the default constant rate devolatilization
model, retain the selection of constant in the
drop-down list to the right of Devolatilization Model and enter the rate constant in the field
below the list.
Select single-rate, two-competing-rates, or cpd-model in the drop-down list to choose one of the optional devolatilization models (the single kinetic rate model, two kinetic rates model, or CPD model, as described in Devolatilization (Law 4) in the Theory Guide).
When the single kinetic rate model (single-rate) is selected, the Single Rate Model Dialog Box will appear; when the two competing rates model (two-competing-rates) is selected, the Two Competing Rates Model Dialog Box will appear; and when the CPD model (cpd-model) is selected, the CPD Model Dialog Box will appear.
See Setting Material Properties for the Discrete Phase for details.
defines which version of the surface char combustion law (Law 5) is being used. If you want to use the default diffusion-limited rate model, retain the selection of diffusion-limited in the drop-down list. No additional inputs are necessary, because the binary diffusivity defined above will be used in Equation 16–167 in the Theory Guide.
To use the kinetics/diffusion-limited rate model for the surface combustion model, select kinetics/diffusion-limited in the drop-down list and enter the parameters in the resulting Kinetics/Diffusion-Limited Combustion Model Dialog Box.
To use the intrinsic model for the surface combustion model, select intrinsic-model in the drop-down list and enter the parameters in the resulting Intrinsic Combustion Model Dialog Box.
To use the multiple surface reactions model, select multiple-surface-reactions in the drop-down list.
See Setting Material Properties for the Discrete Phase for details.
specifies the latent heat for the melting and solidification
model ( in Equation 18–3 in the Theory Guide).
specifies the solidus temperature for the melting and solidification
model ( in Equation 18–3 in
the Theory Guide). If you are solving for species transport, the solidus temperature
is
in Equation 18–8, and
you specify the method by which it is calculated: either according
to the mixing-law (which is based on the parameters
of the solutes) or a user-defined function.
specifies the liquidus temperature for the melting and solidification
model ( in Equation 18–3 in the Theory Guide). If you
are solving for species transport, the liquidus temperature is
in Equation 18–9, and you specify the
method by which it is calculated: either according to the mixing-law (which is based on the parameters of the solutes)
or a user-defined function.
specifies the melting temperature of pure solvent
( in Equation 18–8 and Equation 18–9 in
the Theory Guide) for the melting and solidification model when species transport
has also been enabled. The solvent is the last species listed under
of the mixture material.
is the lowest alloy melting temperature, which depends on the relative proportions of the mixture composition of the Eutectic species mass fractions.
specifies the slope of the liquidus surface with respect to
the concentration of the solute ( in Equation 18–8 and Equation 18–9 in
the Theory Guide). It is not necessary to specify this value for the solvent. Note
that this option is available only for the melting and solidification
model when species transport has also been enabled.
specifies the partition coefficient with respect to the concentration
of the solute fluid ( in Equation 18–8 and Equation 18–9 in
the Theory Guide). It is not necessary to specify this value for the solvent. Note
that this option is available only for the melting and solidification
model when species transport has also been enabled.
is the mass fraction of a solute in an alloy at which the melting
temperature of the alloy is the lowest possible value ( in Equation 18–10 in the Theory Guide). It is not necessary to specify
this value for the solvent. Note that this option is available only
for the melting and solidification model when species transport has
also been enabled.
allows you to specify the coefficient in Equation 18–24 in the Theory Guide for all the species except the last one in the mixture. Note that this option is available only for the melting and solidification model when the Include Solutal Buoyancy option is enabled.
specifies the rate of diffusion in the solid. Note that this option is available only for the melting and solidification model when the Lever rule is selected and the species transport is enabled.
specifies the diffusion coefficient for a user-defined scalar. This material property is available in the Create/Edit Materials Dialog Box when you specify one or more user-defined scalars in the User-Defined Scalars Dialog Box. If you select defined-per-uds, you will need to specify the diffusion coefficient for each user-defined scalar transport equation in the UDS Diffusion Coefficients Dialog Box.
sets the material electrical conductivity. You may set a constant value, or select one of the other methods from the drop-down list above the real number field. This material property only becomes available if the electric potential model is enabled.
specifies the charge number for a fluid material for a flow involving electrochemical reactions. The default setting of 0 means that the fluid species is neutral. This material property only becomes available if the electric potential model is enabled.
When you are viewing the database, additional properties may be displayed. However, after you copy the material to the local area, only the properties with relevance to the current problem will be displayed.
changes the properties of a locally stored material or creates a new one in the local area. If no material with the specified Name exists locally, ANSYS Fluent will create it. If you have modified the material without changing its name, ANSYS Fluent will simply update the material with your modifications. If you have assigned a new name to the material and a material with this name already exists locally, an error will be indicated; you must then specify a different name or delete the existing material with that name before trying to save the new material.
deletes the currently selected material from the local materials list. It has no effect on the global database.