The Discrete Phase Model dialog box allows you to set parameters related to the calculation of a discrete phase of particles. See Modeling Discrete Phase for details.

Controls
contains parameters used for performing coupled calculations of the continuous and discrete phase flow. See Procedures for a Coupled Two-Phase Flow for details.
enables a coupled calculation of the discrete phase and the continuous phase.
enables calculation of particle source terms at every DPM Iteration. For unsteady simulations, it is the default and is recommended.
allows you to control the frequency at which the particles are tracked and the DPM sources are updated.
contains options for enabling cell-averaged discrete phase variables for postprocessing.
enables additional cell-averaged discrete phase variables for postprocessing.
enables additional RMS values for several discrete phase variables for postprocessing.
contains options for choosing to treat the particles in an unsteady or a steady fashion.
enables unsteady tracking of particles.
enables the use of fluid flow time steps to inject the particles.
contains parameters to decide when to inject the particles for a new time step.
enables injection of particles for every particle time step.
enables injection of particles for every fluid flow time step.
In any case, the particles will always be tracked in such a way that they coincide with the flow time of the continuous flow solver, as long as the Max. Number of Steps (in the Tracking tab) used to compute a single trajectory is sufficient.
specifies particle time step size for the calculation.
allows you to specify the number of time steps for the calculation.
clears the particles that are currently in the domain.
contains two parameters to control the time integration of the particle trajectory equations.
contains parameters that control the tracking of particle trajectories.
For steady-state particle tracking, one simple rule of thumb to follow
when setting the two parameters below is that if you want the particles
to advance through a domain of length , the Length Scale times the number of Max. Number of Steps should
be approximately equal to
. See Integration of Particle Equation of Motion in the Theory Guide for
details about the items below.
is the maximum number of time steps used to compute a single particle trajectory via integration of Equation 16–1 in the Theory Guide and Equation 16–58. The default value is 50,000 for steady-state particle tracking and 500 for unsteady particle tracking.
when enabled allows you to specify the length scale.
controls the integration time step size used to integrate the equations of motion for the particle. It appears only when the Specify Length Scale option is enabled.
specifies the value of in Equation 23–3.
contains optional discrete phase models and their relevant parameters.
contains additional models that can be included in the calculation. See Physical Models for the Discrete Phase Model for more information.
includes the effect of radiation heat transfer to the particles (Equation 5–34 in the Theory Guide). You will also need to define additional properties for the particle materials (emissivity and scattering factor), as described in Description of the Properties.
This item appears only if the P-1 or discrete ordinates model is selected in the Radiation Model Dialog Box.
enables the inclusion of a thermophoretic force on the particles as an additional force term. See Thermophoretic Force in the Theory Guide for details.
enables the inclusion of Saffman’s lift force (lift due to shear) as an additional force term. See Saffman’s Lift Force in the Theory Guide for details.
enables the inclusion of virtual mass forces in the particle force balance. See Including the Virtual Mass Force and Pressure Gradient Effects on Particles for details.
enables the inclusion of pressure gradient effects in the particle force balance. See Including the Virtual Mass Force and Pressure Gradient Effects on Particles for details.
enables the monitoring of erosion/accretion rates at wall boundaries. See Monitoring Erosion/Accretion of Particles at Walls for details. This item appears only if Interaction with Continuous Phase is enabled.
allows you to switch from droplet vaporization (Law 2) to boiling (Law 3), as described in Enabling Pressure Dependent Boiling.
allows you to include the droplet temperature effects on the latent heat, as described in Equation 16–113 in the Theory Guide.
enables the effect of change in turbulent quantities due to particle damping and turbulence eddies.
allows you to model DEM collision as described in Modeling Collision Using the DEM Model.
enables the effect of droplet collisions, as described in Collision and Droplet Coalescence Model Theory in the Theory Guide.
enables the effect of droplet coalescence, as described in Collision and Droplet Coalescence Model Theory in the Theory Guide. This option is available when the Stochastic Collision option is enabled.
enables breakup for all suitable injections. You can select the breakup model and parameters, or disable breakup, for each injection in the Set Injection Properties Dialog Box.
contains an option to Consider Children in the Same Tracking Step. This control appears only when either Breakup is enabled under Options or wall-film is selected for Boundary Cond. Type in the DPM tab of the Wall dialog box.
contains model settings that allow you to continue your setup of the model.
is enabled by default. This adjusts the width of the collision mesh to the largest parcel diameter multiplied by the Edge Scale Factor
is the factor by which the width of the collision mesh is adjusted to the largest parcel diameter.
is the fixed width of the collision mesh. This appears when the Adaptive Collision Mesh Width is disabled.
limits the maximum particle velocity to a physically plausible range.
opens the DEM Collisions Dialog Box. This button is available at the bottom of the Discrete Phase Model dialog box when the DEM Collision model is enabled.
contains parameters that can be used to customize the discrete phase model using a user-defined function. See the separate Fluent Customization Manual for details about user-defined functions.
lists will show available user-defined functions that can be selected to customize the discrete phase model.
contains a drop-down list of user-defined functions available for including additional body forces.
contains a drop-down list of user-defined functions available for incorporating non-standard erosion rate definitions. This item will appear only when the Erosion/Accretion option has been enabled.
contains a drop-down list of user-defined functions available for calculating or integrating scalar values along the particle trajectory.
contains a drop-down list of user-defined functions available for modifying interphase exchange terms.
contains a drop-down list of user-defined functions available for modifying spray collide function.
contains a drop-down list of user-defined functions available for modifying DPM time step.
contains a drop-down list of user-defined functions available for modifying the impingement model. If selected, the Impingement Model UDF will overwrite the impingement/splashing model selected for the Lagrangian or Eulerian wall film boundary condition. This item is available only when either wall-film is selected for Boundary Cond. Type in the DPM tab of the Wall dialog box or the Eulerian Wall Film model is enabled.
contains a drop-down list of user-defined functions available for setting the film regime of particle impingement. This item is available only when either wall-film is selected for Boundary Cond. Type in the DPM tab of the Wall dialog box or the Eulerian Wall Film model is enabled.
contains a drop-down list of user-defined functions available for modifying distribution of splashed particle variables. If selected, the Splashing Distribution UDF will overwrite the impingement/splashing model selected for the Lagrangian or Eulerian wall film boundary condition. This item is available only when either wall-film is selected for Boundary Cond. Type in the DPM tab of the Wall dialog box or the Eulerian Wall Film model is enabled.
lists the user input variables.
sets the number of scalar values used in the calculations with user-defined functions.
tab gives you control over the numerical schemes for particle tracking as well as solutions of heat and mass equations. See Numerics of the Discrete Phase Model for details.
contains parameters of solutions of heat and mass equations.
enables the solution of equations of motion within a specified tolerance.
is the maximum relative error that has to be achieved by the tracking procedure.
is the maximum number of step size refinements in one single integration step. If this number is exceeded the integration will be conducted with the last refined integration step size.
enables tracking the particles in the absolute reference frame.
contains parameters for selection of numerical schemes.
enables a mechanism to switch in an automated fashion between numerically stable lower order schemes and higher order schemes, which are stable only in a limited range.
can be chosen from the group consisting of trapezoidal and runge-kutta scheme.
consists of implicit and the exponential analytic integration scheme.
allows you to choose any of the tracking schemes. You also can combine each of the tracking schemes with Accuracy Control. It is selectable only if Automated is switched off.
enables the solution of the corresponding equations using a coupled ODE solver with error tolerance control for the Droplet, Combusting, or Multicomponent particles. See Including Coupled Heat-Mass Solution Effects on the Particles for details.
for the Mass and Heat are set at the default values of 0.3 and 0.1, respectively. See Including Coupled Heat-Mass Solution Effects on the Particles for details.
contains settings for node based averaging of DPM quantities. See Node Based Averaging of Particle Data for details.
enables node based averaging and displays additional related options.
enables averaging of source terms for the discrete phase.
enables averages during each integration time step.
enables averaging of DDPM variables when the DDPM model is active.
contains settings for the kernel used by the node based averaging algorithm.
selects the kernel to use for averaging
sets the constant for the Gaussian distribution when gaussian is selected for Averaging Kernel.
enables the linearization of source terms for the discrete phase.
contains parameters that control the compute nodes for performing discrete phase calculations in parallel. See Parallel Processing for the Discrete Phase Model for details.
allows you to select the mode for parallel processing.
enables cluster computing and also works on shared-memory machines. With this option, the compute node processes themselves perform the particle work on their local partitions and particle migration to other compute nodes is implemented using message passing primitives. No special requirements are placed on the host machine. Note that this model is not available if the Cloud Model option is enabled in the Turbulent Dispersion tab of the Set Injection Properties dialog box.
allows you to specify parameters for performing the calculations on shared-memory multiprocessor machines.
allows you to combine Message Passing (as previously described) and OpenMP for a dynamic load balancing without migration of cells. This option enables multicore cluster computing, and also works on shared-memory machines. When using the Hybrid option, you can control the maximum number of threads on each machine via the Thread Control dialog box (see Controlling the Threads for details). Note that this option is not available if the Cloud Model option is enabled in the Turbulent Dispersion tab of the Set Injection Properties dialog box.
contains settings for the Shared Memory option. This group box is only available on Linux, when the Shared Memory is selected from the Methods list.
specifies that the discrete phase calculations are to be performed on a shared-memory multiprocessor machine.
specifies the number of threads to be used in performing the particle calculations. By default, this parameter is equal to the number of compute nodes you specified for the parallel solver. (This item appears only if Workpile Algorithm is enabled.)
contains settings for the Hybrid option. This group box is only available if Hybrid is selected from the Methods list.
enables the use of a separate computational domain for particle tracking, which improves load balancing and scalability at the expense of some additional memory overhead.