37.10.10. Dynamic Mesh Zones Dialog Box

The Dynamic Mesh Zones dialog box allows you to specify the motion of the dynamic zones in your model. See Specifying the Motion of Dynamic Zones for details.

Controls

Zone Names

contains the names of the zones in the model.

Type

contains the types of motion that can be specified for a dynamic zone.

Stationary

explicitly declares the zone as stationary, so that the nodes on this zone are excluded when updating the node positions. See Specifying the Motion of Dynamic Zones for more information.

Rigid Body

specifies the zone as having a rigid-body motion.

Deforming

specifies the zone as deforming.

User-Defined

enables you to specify a user-defined zone motion.

System Coupling

allows the zone to be involved in a system coupling simulation where the motion is defined by the application that ANSYS Fluent is coupled with on this zone (see the Fluent in Workbench User's Guide and the System Coupling Guide for more details). Once enabled, the Solver Options tab can be used to help achieve convergence for system coupling cases where the physics is strongly coupled. If a dynamic mesh zone of the type System Coupling exists, and ANSYS Fluent is not involved in a system coupling simulation, then this zone type behaves in the same way as a stationary zone.

Dynamic Mesh Zones

lists all of the dynamic zones in the case.

Motion Attributes

contains parameters to specify the motion attributes for a rigid-body-motion zone and a user-defined-motion zone.

Motion/UDF Profile

allows you to define the motion of the rigid body zone by selecting a profile or user-defined function from the drop-down list. See Profiles and Solid-Body Kinematics for information on profiles, and see the Fluent Customization Manual for information on user-defined functions.

Six DOF UDF/Properties

allows you to define the motion of a rigid body zone by selecting a profile, user-defined function, or set of six DOF properties (created using the Six DOF Properties Dialog Box) from the drop-down list. This option is available only when On is enabled in the Six DOF group box.

Six DOF

contains parameters for the Six DOF solver.

On

enables the use of the Six DOF solver.

Passive

(if enabled) does not take forces and moments on the zone into consideration.

Center of Gravity Location

contains the current values of the coordinates for the location of the center of gravity / rotation of the selected zone. This item will appear only if the motion Type is Rigid Body and In-Cylinder is not enabled in the Dynamic Mesh task page.

Relative Motion

allows you to specify the motion of the dynamic zone as relative to another pre-defined rigid body zone. This group box will only appear if the Type is Rigid Body or User-Defined; for the latter, the Relative Zone must be a cell zone.

Rigid Body Orientation

contains the current values of the coordinates for the orientation of the rigid body of the selected zone. This item will appear only if the motion Type is Rigid Body and In-Cylinder is not enabled in the Dynamic Mesh task page.

Center of Gravity Velocity

specifies the velocity of the center of gravity / rotation with respect to inertia coordinate system. This option is available only if the Six DOF solver is the selected model.

Rigid Body Angular Velocity

specifies the angular velocity of the rigid body with respect to inertia coordinate system. This option is available only if the Six DOF solver is the selected model.

Lift/Stroke

contains the current value of valve lift or piston stroke, which is automatically updated when you click Create. This item will appear only if In-Cylinder is enabled in the Dynamic Mesh task page.

Valve/Position Axis

specifies the direction of the reference axis of the valves or piston for an in-cylinder problem. This item will appear only if In-Cylinder is enabled in the Dynamic Mesh task page.

Mesh Motion UDF

allows you to select the user-defined function that defines the geometry and motion of the zone. This item will appear only if the motion Type is User-Defined.

Exclude Mesh Motion in Boundary Conditions

allows you to specify that the boundary mesh motion should not be included in the physical boundary conditions of that zone. This option is only available for non-periodic boundary zones.

Geometry Definition

contains parameters to define a deforming zone.

Definition

allows you to select a geometry definition to project nodes of the deforming zone on. Available options are faceted, plane, cylinder, and user-defined.

Feature Detection

allows you to preserve features for 3D cases on boundary zones of type Deforming or User-Defined. Such features may be at the juncture of different boundary zones, or they may be on a single non-planar boundary zone.

Include Features

enables the detection and preservation of features of a particular angular range.

Feature Angle

defines a threshold value in degrees. For details on how this angle is defined, see Feature Detection.

Point on Plane

allows you to specify the position of a point on the plane. This item will appear only when you select plane for the Definition.

Plane Normal

allows you to specify the direction of the plane normal. This item will appear only when you select plane for the Definition.

Cylinder Radius

allows you to specify the radius of the cylinder. This item will appear only when you select cylinder for the Definition.

Cylinder Origin

allows you to specify the location of the cylinder origin. This item will appear only when you select cylinder for the Definition.

Cylinder Axis

allows you to specify the direction of the cylinder axis. This item will appear only when you select cylinder for the Definition.

Geometry UDF

allows you to select a user-defined function for a geometry Definition.

Meshing Options

contains parameters for various meshing options.

Adjacent Zone

contains the name of the adjacent zone that is involved in local remeshing or dynamic layering. This item will appear only if the zone type is Stationary, Rigid Body, or User-Defined, and if the zone is not the boundary of a CutCell dynamic cell zone.

Cell Height

allows you to specify the ideal height of the adjacent cells as either a constant value or a compiled user-defined function. This item will appear only if the motion Type is Stationary, Rigid Body, or User-Defined, and if the zone is not the boundary of a CutCell dynamic cell zone.

Deform Adjacent Boundary Layer with Zone

enables the smoothing of an adjacent boundary layer mesh. This option is not available when Stationary or Deforming is selected in the Type list.

Methods

contains options to specify the mesh update method(s) and controls on a zone by zone basis. These options and parameters will override those that you specified globally in the Dynamic Mesh task page. This item will appear only if the motion Type is Deforming.

Smoothing

enables the smoothing mesh update method.

Layering

enables the layering mesh update method (valid for a prismatic cell zone only). This item will appear only if the zone you are defining is a cell (fluid) zone.

Remeshing

enables the remeshing mesh update method.

Smoothing Elements

allows you to specify the element types for which spring-based smoothing is used. This item will only be available if you have selected a cell zone and if spring-based smoothing has been enabled.

Global Settings

specifies that the zonal settings are the same as set globally in the Mesh Method Settings dialog box (see Applicability of the Spring-Based Smoothing Method or Mesh Method Settings Dialog Box).

Tet in Tet Zones

(3D only) specifies that this zone will only get smoothed if it consists entirely of tetrahedral elements.

Tri in Tri Zones

(2D only) specifies that this zone will only get smoothed if it consists entirely of triangular elements.

Tet in Mixed Zones

specifies that all simplex elements in this zone should get smoothed. All other elements in a mixed element zone will not undergo smoothing.

All

specifies that all element types in this zone will get smoothed.

Zone Parameters

contains a set of remeshing criteria that, if revised (with reasonable values), will be used for the dynamic zone rather than those you specified globally in the Remeshing tab of the Mesh Method Settings dialog box. Note that this group box is not available if the CutCell option in the Remeshing Options group box is enabled.

Minimum Length Scale

allows you to specify the minimum length scale for the zone. This item will appear only if the zone you are defining is a cell (fluid) zone.

Maximum Length Scale

allows you to specify the maximum length for the zone. This item will appear only if the zone you are defining is a cell (fluid) zone.

Maximum Skewness

allows you to specify the desired value for maximum skewness.

Zone Scale Info...

opens the Zone Scale Info Dialog Box, in which you can view the statistics of the mesh, such as minimum, maximum, and average length scale values, as well as the maximum skewness.

CutCell Zone Parameters

contains a set of global parameters used for CutCell zone remeshing. This group box will only appear if the zone selected in the Dynamic Mesh Zones list is a cell zone, and if the CutCell option is enabled in the Remeshing Options group box.

Maximum Mesh Size

allows you to specify the maximum mesh size of the Cartesian CutCell mesh.

Growth Rate

allows you to specify the default growth rate used for mesh refinement by size functions. This growth rate is used during remeshing by the mesh-based size functions of all boundaries of the CutCell cell zone that are not defined as dynamic mesh zones.

Minimum Orthogonal Quality

allows you to specify the minimum allowable orthogonal quality for the cell zone. CutCell remeshing will occur if the orthogonal quality for any cell in the cell zone drops below this value.

Remeshing Interval

specifies the interval of time steps at which the cell zone remeshing will take place, even if the mesh quality has not deteriorated below the value entered for Minimum Orthogonal Quality. Enter a value of 0 for the Remeshing Interval if you want the remeshing to occur only if there is insufficient mesh quality.

Inflation Layers

allows you to enable inflation layers on the CutCell cell zone and specify global inflation parameters.

Settings...

opens the Inflation Settings Dialog Box, which allows you to enter the global inflation parameters used by default on all boundary zones.

Boundary Zones Info...

opens the CutCell Boundary Zones Info Dialog Box, which lists all of the boundary zones for the CutCell dynamic cell zone, along with the remeshing and inflation layer parameters.

Zone Scale Info...

opens the Zone Scale Info Dialog Box, in which you can view the statistics of the mesh, such as minimum, maximum, and average length scale values, as well as the maximum skewness.

CutCell Boundary Zone Parameters

contains a set of local parameters used for CutCell zone remeshing. This group box will only appear if the zone selected in the Dynamic Mesh Zones list is a boundary of a CutCell dynamic cell zone.

Maximum Mesh Size

allows you to specify the maximum mesh size used by the soft size function. If a value of 0 is entered, a mesh-based size function is used to locally refine the Cartesian mesh near the boundary.

Growth Rate

allows you to specify the local growth rate used by the size function.

Zonal Inflation Layer Control

allows you to enable local inflation layer control and specify local inflation parameters. This option is only available if Inflation Layers has been enabled for the CutCell dynamic cell zone. If Zonal Inflation Layer Control is not enabled, then the global inflation parameters specified for the cell zone are used.

Settings...

opens the Inflation Settings Dialog Box, which allows you to enter local inflation parameters for the CutCell boundary zone.

Zone Scale Info...

opens the Zone Scale Info Dialog Box, in which you can view the statistics of the mesh, such as minimum, maximum, and average length scale values, as well as the maximum skewness.

Smoothing Methods

contains two methods of smoothing. This option is only available if spring-based smoothing has been selected in the Mesh Method Settings dialog box.

Spring

enables spring-based smoothing method.

Laplace

enables Laplacian smoothing method.

Remeshing Methods

contains two methods of remeshing. This group box will appear only when the motion Type is Deforming.

Region

enables region-based remeshing method.

Local

enables local remeshing method.

Remeshing Method

provides settings for local face remeshing of the dynamic zone. This group box will appear only for boundary zones, when the motion Type is User-Defined.

Local

enables local face remeshing for the dynamic zone. This option is only available when Local Face is enabled in the Remeshing tab of the Mesh Method Settings Dialog Box.

Maximum Skewness

is a field that, if revised (with a reasonable value), sets a maximum skewness for the local face remeshing of the dynamic zone that is different than the global value set in the Remeshing tab of the Mesh Method Settings Dialog Box.

Remeshing Options

contains one method of remeshing.

CutCell

enables the CutCell zone remeshing method. This option is only available when the CutCell Zone is enabled in the Mesh Method Settings dialog box, and if the zone selected in the Dynamic Mesh Zones list of the Dynamic Mesh Zones dialog box is a cell zone.

Solver Options

contains settings that may help convergence for boundary zones in cases that involve strong fluid-structure interaction (notably zones undergoing rigid body motion with the six degree of freedom solver or system coupling motion). See Solution Stabilization for Dynamic Mesh Boundary Zones for more information.

Solution Stabilization

enables/disables solution stabilization settings for boundary zones.

Stabilization Parameters

contains options for solution stabilization settings.

Scale Factor

allows you to set the scale factor used by the selected Method for convergence stabilization.

Method

Stabilization is achieved through a boundary source coefficient introduced in the continuity equation. It is designed to improve the diagonal dominance of the matrix system in the cells adjacent to the boundary zone. Two methods for this boundary source coefficient are available:

volume-based

(default) specifies that the diagonal entry of the linear matrix system corresponding to the discretized continuity equation is re-scaled using the cell volume and a scale factor, according to Equation 10–32.

coefficient-based

specifies that the diagonal entry of the linear matrix system corresponding to the discretized continuity equation is directly re-scaled by a scale factor, according to Equation 10–33.


Release 18.2 - © ANSYS, Inc. All rights reserved.