If you have created a surface, but you do not want to use the whole surface to display
data, you can clip the surface between two isovalues to create a new surface that spans a
specified subrange of a specified scalar quantity. The clipped surface consists of those points
on the selected surface where the scalar field values are within the specified range. For
example, in Figure 30.14: External Wall Surface Isoclipped to Values of x Coordinate the external wall has been clipped to
values of coordinate less than 0 to show only the back half of the wall, enabling you to
see the valve inside the intake port.
To clip an existing surface, you will use the Iso-Clip Dialog Box (Figure 30.15: The Iso-Clip Dialog Box).
Setting Up Domain → Surface
→ Create → Iso-Clip...
The steps for clipping a surface are as follows:
Choose the scalar variable on which the clipping will be based in the Clip To Values Of drop-down list. First, select the desired category in the upper list. You can then select from related quantities from the lower list. See Field Function Definitions for an explanation of the variables in the list.
Select the surface to be clipped in the Clip Surface list.
Click to calculate the minimum and maximum values of the selected scalar field on the selected surface. The minimum and maximum values are displayed in the Min and Max fields.
Define the clipping range using one of the following methods.
You can set the upper and lower limits of the clipping range interactively by moving the indicator in each dial (that is, the dial above the Min or Max field) with the left mouse button. The value in the corresponding Min or Max field is updated automatically. This method will also create a temporary surface in the graphics window. Using the dials enables you to preview a clipped surface before creating it.
Important: Even though the clipped surface is displayed, it is only a temporary surface. To create the new surface, use the Clip button after deciding on the clipping range.
You can type the minimum and maximum values in the clipping range directly in the Min and Max fields.
If you do not want to use the default name assigned to the surface, enter a new name
under New Surface Name. The default name is the concatenation of the
surface type and an integer that is the new surface ID (for example,
clip-density-8). (If the New Surface Name you
enter is the same as the name of a surface that already exists, ANSYS Fluent will
automatically assign the default name to the new surface when it is created.)
Important: The surface name that you enter must begin with an alphabetical letter. If the name of the surface begins with any other character or number, ANSYS Fluent rejects the entry.
Click . The new surface name is added to the Clip Surface list in the dialog box. (The original surface will remain unchanged.)
If you want to delete or otherwise manipulate any surfaces, click to open the Surfaces Dialog Box. See Grouping, Renaming, and Deleting Surfaces for details.