The Multiphase Model dialog box allows you to set parameters for modeling multiphase flow. See Enabling the Multiphase Model – Including Cavitation Effects for details.

Controls
allows you to select one of four multiphase models.
disables the calculation of multiphase flow.
enables the VOF model described in Volume of Fluid (VOF) Model Theory in the Theory Guide. See Setting Up the VOF Model for details about using the model. This is available only with the pressure-based solver.
enables the mixture model described in Mixture Model Theory in the Theory Guide. See Setting Up the Mixture Model for details about using the model. This is available only with the pressure-based solver.
enables the Eulerian model described in Eulerian Model Theory in the Theory Guide. See Setting Up the Eulerian Model for details about using the model. This is available only with the pressure-based solver.
enables the wet steam model described in Wet Steam Model Theory in the Theory Guide. See Setting Up the Wet Steam Model for details about using the model. This is available only with the density-based solver.
allows you to specify the number of phases for the multiphase calculation. You can specify up to 20 phases.
allows you to apply an interface tracking method that couples the level set method with the VOF formulation.
contains parameters related to the VOF and Eulerian model. This section of the dialog box will appear only when Volume of Fluid or Eulerian is the selected Model.
allows you to select the desired volume tracking formulation.
enables the Euler explicit formulation, described in The Explicit Formulation in the Theory Guide. See Choosing Volume Fraction Formulation for more information.
enables the implicit formulation, described in The Implicit Formulation in the Theory Guide. See Choosing Volume Fraction Formulation for more information.
specifies a cutoff limit for the volume fraction values. The value that you provide is used as the lower cutoff for the volume fraction. All volume fraction values in the domain below this cutoff value are set to zero. The upper cutoff is calculated as (1.0 - lower cutoff). All volume fraction values above the upper cutoff value are set to 1.0. The default value is 1e-6.
Important: The Volume Fraction Cutoff value can be specified when using the VOF model, or when using the Eulerian Multiphase model with the Explicit scheme.
specifies the maximum Courant number allowed near the free surface. This item will not appear if the Implicit Scheme is selected. See Setting Time-Dependent Parameters for the Explicit Volume Fraction Formulation for details.
contains options related to the Mixture model.
enables/disables the calculation of slip velocities for the secondary phases as described in Relative (Slip) Velocity and the Drift Velocity in the Theory Guide. See also Solving a Homogeneous Multiphase Flow.
contains options related to the Eulerian model.
allows you to include the Dense Discrete Phase model (see Including the Dense Discrete Phase Model for details). Enabling this model automatically enables the DPM model.
allows you to include the multi-fluid VOF model (see Including the Multi-Fluid VOF Model for details). The multi-fluid VOF model allows the modeling of interface sharpening schemes and free surface flow.
allows you to include the Boiling model (see Including the Boiling Model for details).
allows you to select the type of boiling model to apply to your case.
is where the total heat flux from the wall to the liquid is partitioned into three components, namely the convective heat flux, the quenching heat flux, and the evaporative heat flux. Details about this model can be found in RPI Model in the Theory Guide.
is a modification to the RPI model in order to model different boiling regimes like DNB and critical heat flux. Details about this model can be found in Non-equilibrium Subcooled Boiling in the Theory Guide.
is where the critical heat flux condition is characterized by a sharp reduction of local heat transfer coefficients and the excursion of wall surface temperatures. Details about this model can be found in Critical Heat Flux in the Theory Guide.
allows you to select the evaporation-condensation model to use in your simulation.
enables the Lee Model, which is the same model that is used with VOF and the mixture model. Details about this model can be found in Lee Model in the Fluent Theory Guide.
enables the thermal phase change model. Details about this model can be found in Thermal Phase Change Model in the Fluent Theory Guide.
allows you to specify the number of discrete phases when the Dense Discrete Phase Model option is enabled.
contains an additional option for body force calculations.
enables the implicit body force treatment described in Including Body Forces.
contains additional sub-models that can be applied when using the VOF model.
enables the model to study the effects of open channel flow. See Open Channel Flow in the Theory Guide and Modeling Open Channel Flows for details.
enables the model to set specific parameters for a particular boundary for open channel wave boundaries. See Open Channel Wave Boundary Conditions in the Theory Guide and Modeling Open Channel Wave Boundary Conditions for details.
contains additional modeling options.
contains settings for how to model interfaces for the VOF model and Eulerian with Multi-Fluid VOF enabled. See Interface Modeling Type for details.
allows you to select the type of interface modeling to be performed. You can choose between Sharp, Dispersed, or a hybrid Sharp/Dispersed when both types of interfaces may be present, or when the interface is mildly sharp. See Interface Modeling Type for more details.
enables an anti-diffusion treatment at the interface when using the Sharp interface modeling type. This can be used to reduce the effects of numerical diffusion that may occur with coarse meshes, high-aspect ratio cells, or large jumps in cell volume near the interface.
opens the Interface Modeling Options dialog box from which you can enable Zonal Discretization and/or Phase Localized Discretization.
opens the Expert Options dialog box which contains settings for VOF time advancement when using the Explicit formulation. Here you can set the Sub-Time Step Calculation Method and enable Solve VOF Every Iteration. See Expert Options for details.