If you are using the parallel version of ANSYS Fluent (see Parallel Processing), you may find it useful to create data surfaces defined by the boundaries of mesh partitions. As described in Mesh Partitioning and Load Balancing, partitioning the mesh divides it into groups of cells that can be solved on separate processors when you use a parallel solver. A partition surface will contain faces or cells on the boundary of two mesh partitions. For example, you can plot solution values on the partition surface to determine how the solution is changing across a partition interface, as shown in the following figure:
To create a partition surface, you will use the Partition Surface Dialog Box (Figure 30.3: The Partition Surface Dialog Box).
Setting Up Domain → Surface
→ Create → Partition...
The procedure for creating the partition surface are as follows:
Specify the partition boundary in which you are interested by indicating the two bordering partitions under the Partitions heading. The boundary that defines the partition surface is the boundary between the "interior partition" and the "exterior partition". Int Part indicates the ID number of the interior partition (that is, the partition under consideration), and Ext Part indicates the ID number of the bordering (exterior) partition. The Min and Max fields will indicate the minimum and maximum ID numbers of the mesh partitions. The minimum is always zero, and the maximum is one less than the number of processors. If there are more than two mesh partitions, each interior partition will share boundaries with several exterior partitions. By setting the appropriate values for Int Part and Ext Part, you can create surfaces for any of these boundaries.
Choose interior or exterior faces or cells to be contained in the partition surface by selecting or clearing Cells and Interior under Options. To obtain a surface consisting of cells that are on the "interior" side of the partition boundary, select both Cells and Interior. To create one consisting of cells that are on the "exterior" side, select Cells and clear Interior. If you want the surface to contain the faces on the boundary instead of the cells, clear the Cells option. To have the faces reflect data values for the interior cells, select the Interior check box, and to have them reflect values for the exterior cells, clear it.
If you do not want to use the default name assigned to the surface, enter a new name
under New Surface Name. The default name is the concatenation of the
surface type and an integer that is the new surface ID (for example,
partition-surface-6). (If the New Surface Name
you enter is the same as the name of a surface that already exists, ANSYS Fluent will
automatically assign the default name to the new surface when it is created.)
Important: The surface name that you enter must begin with an alphabetical letter. If the name of the surface begins with any other character or number, ANSYS Fluent rejects the entry.
Click . The new surface name is added to the Surfaces list in the dialog box.
If you want to delete or otherwise manipulate any surfaces, click to open the Surfaces Dialog Box. For details, see Grouping, Renaming, and Deleting Surfaces.