37.4.18. Species Model Dialog Box

The Species Model dialog box allows you to set parameters related to the calculation of species transport and combustion. See Enabling Species Transport and Reactions and Choosing the Mixture Material, Manual Inputs for Wall Surface Reactions, User Inputs for Particle Surface Reactions, Using the Premixed Combustion Model, Using the Partially Premixed Combustion Model, and Steps for Using the Composition PDF Transport Model for details about the items below.

Controls

Model

indicates which model, if any, is used to calculate species transport/combustion.

Off

disables species calculations.

Species Transport

enables the calculation of multi-species transport (either non-reacting or reacting, depending on the selection for Reactions). See Modeling Species Transport and Finite-Rate Chemistry for details.

Non-Premixed Combustion

enables the calculation of turbulent reacting flow using the non-premixed combustion model. See Modeling Non-Premixed Combustion for details. This option is available only for turbulent flows using the pressure-based solver.

Premixed Combustion

enables the premixed turbulent combustion model. See Modeling Premixed Combustion for details. This option is available only for turbulent flows using the pressure-based solver.

Partially Premixed Combustion

enables the partially premixed turbulent combustion model. See Modeling Partially Premixed Combustion for details. This option is available only for turbulent flows using the pressure-based solver.

Composition PDF Transport

enables the composition PDF transport model. See Modeling a Composition PDF Transport Problem for details. This option is available only for turbulent flows using the pressure-based solver.

Reactions

contains options related to the modeling of reacting flow. (This section of the dialog box appears only when Species Transport or Composition PDF Transport is the specified Model.)

Volumetric

enables the calculation of reacting flow using the finite-rate formulation. See Volumetric Reactions for details.

Wall Surface

enables the calculation of wall surface reactions. See Wall Surface Reactions and Chemical Vapor Deposition for details. This item will appear only if Volumetric is enabled.

Particle Surface

enables the calculation of particle surface reactions. See Particle Surface Reactions for details. This item will appear only if Volumetric is enabled.

Electrochemical

enables the calculation of electrochemical reactions. See Electrochemical Reactions for details. This item will appear only if Volumetric is enabled.

Integration Parameters...

is a command button that opens the Integration Parameters Dialog Box. This button appears for the species transport model, when Volumetric is enabled under Reactions and Stiff Chemistry Solver is enabled under Options or when Eddy-Dissipation Concept is enabled under Turbulence-Chemistry Interaction.

Wall Surface Reaction Options

contains additional options for wall surface reactions. This portion of the dialog box appears only if Wall Surface is enabled under Reactions.

Heat of Surface Reactions

(if enabled) includes the heat release due to surface reactions in the energy equation. You must remember to set appropriate formation enthalpies (standard state enthalpies) if you enable this option.

Mass Deposition Source

(if enabled) includes the effect of surface mass transfer in the continuity equation.

Aggressiveness Factor

is a numerical factor that controls the robustness and the convergence speed. This value ranges between 0 and 1, where 0 is the most robust, but results in the slowest convergence. The default value for the Aggressiveness Factor is 0.5.

Chemistry Solver

is a drop-down list in which you can select the solver for the chemically reactive flow simulation. This item appears only for Species Transport and Composition PDF Transport models involving Volumetric reactions.

Stiff Chemistry Solver

enables efficient integration of stiff chemical kinetics. This item appears only when Finite-Rate/No TCI or Eddy-Dissipation Concept is selected in the Turbulence-Chemistry Interaction group box. See Solution of Stiff Chemistry Systems for details.

CHEMKIN-CFD Solver

enables the integration of chemical kinetics using the ANSYS CHEMKIN-CFD Solver, designed for large, stiff chemistry mechanisms. This item appears only when Finite-Rate/No TCI or Eddy-Dissipation Concept is selected in the Turbulence-Chemistry Interaction group box.

Relax to Chemical Equilibrium

enables efficient modeling of chemical kinetics effects based only on equilibrium calculation and assumptions about characteristic timescales for approaching equilibrium. This item is not available for the Eddy Dissipation Concept TCI option. (See The Relaxation to Chemical Equilibrium Model for details.

None - Explicit Source

makes explicit use of chemistry source terms in the species transport equations, without a stiff-chemistry solver (not recommended for stiff or complex chemistry).

Options

contains additional options for the Species Transport model and for the Composition PDF Transport. (This section will not appear in the dialog box for the other models.)

Inlet Diffusion

includes the diffusion flux of species at inlet.

Diffusion Energy Source

(if enabled) includes the effect of enthalpy transport due to species diffusion in the energy equation.

Full Multicomponent Diffusion

enables the full multicomponent diffusion model. See Full Multicomponent Diffusion for details.

Thermal Diffusion

enables the thermal diffusion model. See Thermal Diffusion Coefficients for details.

Liquid Micro-Mixing

is used to model liquid reactions. When the Liquid Micro-Mixing model is invoked, ANSYS Fluent uses the volume-weighted-mixing-law formula to calculate the density.

Species Migration

(if enabled) includes the ion species migration term in the species transport equation. This item appears only when Electrochemical reactions are enabled.

Thickened Flame Model

enables the modeling of laminar flames. This application is typically used as an LES combustion model for turbulent premixed and partially-premixed flames.

Include Temperature Fluctuations

enables the calculation of the multi-mode energy equation. This option is available when the composition PDF transport model is selected.

Mixture Properties

contains controls and information about the mixture being modeled. This section of the dialog box will not appear if Premixed Combustion is the selected under Model.

Mixture Material

contains a drop-down list of available mixture materials. When you first enable the Species Transport model, you can choose from all of the mixture materials defined in the database, or you can choose a “template” and define your own material. (Click View... to open the Fluent Database Materials Dialog Box and check the properties of the mixture material selected in the list.) See Enabling Species Transport and Reactions and Choosing the Mixture Material for details.

When you use the Non-Premixed Combustion or Partially Premixed Combustion model, this list will be inactive. The mixture material for a non-premixed or partially premixed combustion calculation will be determined from the content of the PDF file generated in ANSYS Fluent using the PDF Options parameters.

Number of Volumetric Species

displays the number of gas-phase species in the selected Mixture Material. This is an informational display only; you cannot edit this value.

Number of Solid Species

displays the number of solid species defined in the selected Mixture Material. This is an informational display only; you cannot edit this value. (This list will appear only for Species Transport models involving Wall Surface reactions.)

Number of Site Species

displays the number of site species defined in the selected Mixture Material. This is an informational display only; you cannot edit this value. (This list will appear only for Species Transport models involving Wall Surface reactions.)

Turbulence-Chemistry Interaction

indicates which model is to be used for turbulence-chemistry interaction when the Species Transport model with Volumetric reactions is used.

Laminar Finite-Rate

computes only the Arrhenius rate (see Equation 7–7 in the Theory Guide) and neglects turbulence-chemistry interaction.

Finite-Rate/Eddy-Dissipation

(for turbulent flows) computes both the Arrhenius rate and the mixing rate and uses the smaller of the two.

Eddy-Dissipation

(for turbulent flows) computes only the mixing rate (see Equation 7–25 and Equation 7–26 in the Theory Guide).

Eddy-Dissipation Concept

(for turbulent flows) models turbulence-chemistry interaction with detailed chemical mechanisms (see Equation 7–25 and Equation 7–26 in the Theory Guide).

Coal Calculator...

opens the Coal Calculator Dialog Box.

Select Boundary Species...

opens the Select Boundary Species dialog box (see Figure 14.3: The Select Boundary Species Dialog Box).

Select Reported Residuals

opens the Select Residual Monitored Species dialog box (see Figure 14.4: The Select Residual Monitored Species).

Options

contains parameters related to the Laminar Finite-Rate or the Eddy-Dissipation Concept model. This section of the dialog box will appear when Laminar Finite-Rate or the Eddy-Dissipation Concept is selected for Turbulence-Chemistry Interaction.

Flow Iterations Per Chemistry Update

specifies how often ANSYS Fluent will update the chemistry during the calculation. Increasing the number can reduce the computational expense of the chemistry calculations.

Aggressiveness Factor

is a numerical factor that controls the robustness and the convergence speed. This value ranges between 0 and 1, where 0 is the most robust, but results in the slowest convergence. The default value for the Aggressiveness Factor is 0.5.

Volume Fraction Constant

specifies the value of in Equation 7–28 in the Theory Guide.

Time Scale Constant

specifies the value of in Equation 7–29 in the Theory Guide.

Number of Grid Points in Flame

by default are 8 grid points.

PDF Options

contains options related for the non-premixed combustion model. (This section will appear only if Non-Premixed Combustion or Partially-Premixed Combustion is the selected Model.)

Inlet Diffusion

includes the diffusion flux of species at inlet.

Compressibility Effects

can be enabled to account for cases where substantial pressure changes occur in time and/or space when modeling a non-adiabatic system. See Specifying the Operating Pressure for the System for details.

Liquid Micro-Mixing

is used to model liquid reactions. When the Liquid Micro-Mixing model is invoked, ANSYS Fluent uses the volume-weighted-mixing-law formula to calculate the density.

Chemistry

tab contains the parameters to define problems using the chemistry model. See Setting Up the Equilibrium Chemistry Model for details.

State Relation
Chemical Equilibrium

enables the equilibrium chemistry model. See Setting Up the Equilibrium Chemistry Model for details.

Steady Diffusion Flamelet

enables the steady diffusion flamelet model. See The Diffusion Flamelet Models Theory in the Theory Guide for details.

Unsteady Diffusion Flamelet

enables the Eulerian unsteady diffusion flamelet model.

Diesel Unsteady Flamelet

enables the diesel unsteady laminar flamelet model. See Using the Diesel Unsteady Laminar Flamelet Model for details.

Flamelet Generated Manifold

enables the flamelet generated manifold (FGM) model. This is available when the Partially Premixed Combustion model is selected. See Partially Premixed Combustion in the Theory Guide for details.

Energy Treatment
Adiabatic

enables adiabatic modeling options for the problem.

Non-Adiabatic

enables non-adiabatic modeling options for the problem. See Non-Adiabatic Extensions of the Non-Premixed Model in the Theory Guide for details.

Coal Calculator

opens the Coal Calculator Dialog Box.

Stream Options

contains the parameters for the equilibrium chemistry model or the steady diffusion flamelet model.

Secondary Stream

includes the secondary inlet stream in the model.

Empirical Fuel Stream

enables parameters to define fuel stream empirically. This option is available only with the full equilibrium chemistry model.

Empirical Secondary Stream

enables parameters to define secondary stream empirically. This option is available only with the full equilibrium chemistry model.

Model Settings

contains a list of parameter settings.

Operating Pressure

specifies the system operating pressure used to calculate the density using the ideal gas law. See Specifying the Operating Pressure for the System for details.

Fuel Stream Rich Flamability Limit

specifies the rich flammability limit for fuel stream when the equilibrium chemistry option is used. You will not set these if you have used the empirical definition option for fuel composition. See Enabling the Rich Flammability Limit (RFL) Option for details.

Secondary Stream Flamability Limit

specifies the rich flammability limit for secondary stream when the equilibrium chemistry option is used. You will not set these if you have used the empirical definition option for fuel composition. See Enabling the Rich Flammability Limit (RFL) Option for details.

Empirical Fuel Lower Calorific Value

specifies the lower calorific value of fuel stream.

Empirical Fuel Specific Heat

specifies the specific heat value of fuel stream.

Empirical Fuel Molecular Weight

specifies the molecular weight of the fuel stream.

Empirical Secondary Lower Calorific Value

specifies the lower calorific value of secondary stream.

Empirical Secondary Specific Heat

specifies the specific heat value of secondary stream.

Empirical Secondary Molecular Weight

specifies the molecular weight of the secondary stream.

Options

contains options related to the steady flamelet model.

Create Flamelet

enables the Import CHEMKIN Mechanism... button that opens the CHEMKIN Mechanism Import Dialog Box where you can import the CHEMKIN mechanism and thermodynamic data, to create a flamelet file. This option is available for the steady flamelet model. See Setting Up the Steady and Unsteady Diffusion Flamelet Models for details.

Import Flamelet

enables the Import Flamelet File... button that opens The Select File Dialog Box where you can select the existing flamelet in ANSYS Fluent. You can also set the file type parameters to import the existing flamelet in ANSYS Fluent. See Setting Up the Steady and Unsteady Diffusion Flamelet Models for details. This option is available for the steady flamelet model.

Flamelet Type

gives you the option of creating a Premixed Flamelet or a Diffusion Flamelet. This is available when the Flamelet Generated Manifold model is selected.

File Type

contains the toggle buttons for two flamelet file types.

Standard

enables the import of an ASCII format standard flamelet file.

CFX-RIF

enables the import of an ASCII format CFX-RIF flamelet file.

Flamelet Property File Name

opens The Select File Dialog Box in which you can save the existing flamelet in ANSYS Fluent to use when running an existing case.

Thermodynamic Database File Name

specifies a path for the thermodynamic database file to be read.

Boundary

tab contains the list of boundary species and related parameters. This is available only for equilibrium chemistry model. See Defining the Stream Compositions for details.

Species

contains the list of the species used in the problem.

Fuel

specifies the fuel species.

Oxid

specifies the oxidizing species.

Second

specifies the secondary species.

Boundary Species

allows you to specify the species you want to add or remove from the model. You can type the species chemical formula in the field below it.

Add

adds the species in the model.

Remove

removes the species from the model.

List Available Species

prints a list of all species in the thermodynamic database file (thermo.db) in the console window.

Temperature

specifies the temperature of different streams that you have defined.

Fuel

is the temperature of the fuel inlet in the model.

Oxid

is the temperature of the oxidizer inlet in the model.

Second

is the temperature of the secondary stream inlet in the model.

Specify Species in

allows you to define the unit of species concentration.

Mass Fraction

allows you to specify the species in terms of mass fraction.

Mole Fraction

allows you to specify the species in terms of mole fraction.

Control

tab contains the parameters for exclusion and inclusion of equilibrium species. This is available only for equilibrium chemistry model. See Forcing the Exclusion and Inclusion of Equilibrium Species for details.

Species Excluded from Equilibrium

lists the species excluded from equilibrium calculation.

Species

lists the slow-forming species that are zeroed in the initial flamelet profile.

Add

allows you to add equilibrium species.

Remove

allows you to remove equilibrium species.

List Available Species

prints a list of all species in the thermodynamic database file in the console window.

Flamelet Controls

allows you to adjust the controls for the flamelet solution. Note that the Create Flamelet option in the Chemistry tab must be selected for the Steady Diffusion Flamelet or Flamelet Generated Manifold models for these controls to be available.

Initial Fourier Number

sets the first time step for the solution.

Fourier Number Multiplier

increases the time step at subsequent times. Every time step after the first is multiplied by this value.

Relative Error Tolerance and Absolute Error Tolerance

specifies the local error controls during numerical integration.

Flamelet Convergence Tolerance

specifies the maximum absolute change in species fraction or temperature at any discrete mixture-fraction.

Maximum Integration Time

specifies the maximum total elapsed time for flamelet calculation. ANSYS Fluent will stop the flamelet calculation after the total elapsed time has exceeded this value.

Flamelet

tab allows you to adjust the controls for the flamelet solution. See Defining the Flamelet Controls for details.

Flamelet Parameters

consist of the controls for the flamelet solution.


Note:  The parameters may vary slightly if you selected the Flamelet Generated Manifold model (see Flamelet Generated Manifold for those specific parameters).


Number of Grid Points in Flamelet

specifies the number of mixture fraction grid points distributed between the oxidizer () and the fuel ().

Maximum Number of Flamelets

specifies the maximum number of laminar flamelet profiles to be calculated.

Initial Scalar Dissipation

is the scalar dissipation of the first flamelet in the library.

Scalar Dissipation Step

specifies the interval between scalar dissipation values (in ) for which multiple flamelets will be calculated.

User Defined Flamelet Parameters

enables you to hook a user-defined function for scalar dissipation and mean mixture fraction (or progress variable) grid discretization

Include Equilibrium Flamelet

determines whether the equilibrium assumption is used to compute the progress variable (Equation 9–2 in the Fluent Theory Guide). By default, this option is selected. If you turn off this option, ANSYS Fluent will compute the progress variable using the solution of flamelet generated with initial scalar dissipation as a denominator in Equation 9–2 in the Fluent Theory Guide.

Unsteady Flamelet Parameters

consist of the controls for the unsteady flamelet solution.

Number of Grid Points in Flamelet

specifies the number of mixture fraction grid points distributed between the oxidizer () and the fuel ().

Mixture Fraction Lower Limit for Initial Probability

is the limit at which the unsteady flamelet model temporally convects and diffuses a marker probability equation through a steady-state ANSYS Fluent flow-field.

Maximum Scalar Dissipation

is where flamelets extinguish at large scalar dissipation (mixing) rates.

Courant Number

is the number at which ANSYS Fluent automatically selects the time step for the probability equation based on this convective Courant number.

Number of Flamelets

specifies the number of unsteady laminar flamelets that ANSYS Fluent will automatically generate during the simulation.

Calculate Flamelets

begins the laminar flamelet calculation.

Display Flamelets...

opens the Flamelet 3D Surfaces Dialog Box from which you can display 2D plots and 3D surfaces showing the variation of species fraction or temperature with the mean mixture fraction or scalar dissipation.

Initialize Unsteady Flamelet Probability

initializes the unsteady flamelet and its probability marker equation.

Display Unsteady Flamelet...

opens the Flamelet 2D Curves Dialog Box from which you can display 2D plots of the different variables.

Table

tab contains parameters to create the look-up table. See Calculating the Look-Up Tables for details of the items listed below.


Note:  If you selected the Flamelet Generated Manifold model, the parameters will be different. See Calculating the Look-Up Tables for those specific parameters.


Table Parameters

consists of the controls for the lookup table. A different set of parameters for you to enter will be displayed if Automated Grid Refinement is enabled or disabled.

Initial Number of Grid Points

specifies the number of grid points for the resolution of the mean mixture fraction, mixture fraction variance, and mean enthalpy (for non-adiabatic systems).

Maximum Number of Grid Points

specifies the maximum number of grid points used for tabulation. The grid refinement procedure will stop inserting the points when either the change in value and slope between successive points is within tolerance or the maximum number of grid points are generated.

Maximum Change in Value Ratio

specifies the maximum allowable change in value of table variables between successive grid points as specified by Equation 8–27 in the Theory Guide.

Maximum Change in Slope Ratio

specifies the maximum change in the slope of table variables between successive grid points as specified by Equation 8–28 in the Theory Guide.

Maximum Number of Species

is the maximum number of species stored in the lookup tables.

Minimum Temperature

specifies the minimum temperature in the lookup tables.

Number of Mean Mixture Fraction Points

is the number of discrete values of at which the look-up tables will be computed.

Number of Secondary Mixture Fraction Points

is the number of discrete values of at which the look-up tables will be computed. This option is available only when a secondary stream has been defined.

Number of Mixture Fraction Variance Points

is the number of discrete values of at which the look-up tables will be computed. This option is available only when no secondary stream has been defined.

Maximum Number of Species

is the maximum number of species that will be included in the look-up tables.

Number of Mean Enthalpy Points

is the number of discrete values of enthalpy at which the three-dimensional look-up tables will be computed. This input is required only if you are modeling a non-adiabatic system.

Minimum Temperature

is used to determine the lowest temperature for which the look-up tables are generated (see Figure 8.10: Visual Representation of a Look-Up Table for the Scalar as a Function of Mean Mixture Fraction and Mixture Fraction Variance and Normalized Heat Loss/Gain in Non-Adiabatic Single-Mixture-Fraction Systems in the Theory Guide). This option is available only if you are modeling a non-adiabatic system.

Automated Grid Refinement

is an adaptive algorithm that inserts grid points in all table dimensions so that changes in the values of tabulated variables (such as mean temperature, density and species mass fractions) between successive grid points, as well as changes in their slopes, are less than a user specified tolerance.

Include Equilibrium Flamelet

specifies that an equilibrium flamelet (that is, ) will be generated in ANSYS Fluent and appended to the flamelet library before the PDF table is calculated. This option is available only when you are generating more than one laminar flamelet.

FGM Scalar Transport

opens the Select Transported Scalars Dialog Box.

Calculate PDF Table

generates the look-up table.

Display PDF Table

opens the PDF Table Dialog Box where you can display 2D plots and 3D surfaces showing the variation of species mole fraction, density, or temperature with the mean mixture fraction, mixture fraction variance, or enthalpy.

Properties

tab contains parameters needed to modify the piecewise-linear points. See Modifying the Unburnt Mixture Property Polynomials for the details.

Partially Premixed Mixture Properties

contains the list of properties that you can modify. Edit... opens the Quadratic Mixture Fraction dialog box where you can modify the values of the polynomial coefficients.

For each polynomial function of under Partially Premixed Mixture Properties you can click Edit... and specify values for Coefficient 1, Coefficient 2, Coefficient 3, and Coefficient 4 in the appropriate Quadratic of Mixture Fraction dialog box.

Non-Adiabatic Laminar Flame Speed

when enabled includes the non-adiabatic effects on the laminar flame speed by tabulating the laminar speeds in the PDF table. See Laminar Flame Speed in the Theory Guide.

Recalculate Properties

will calculate the partially premixed properties.

Premix

tab contains the options and the parameters for the Turbulent Flame Speed Model, the Variance Settings, and the Turbulence-Chemistry Interaction.

Turbulent Flame Speed Model

contains the Flame Speed Model drop-down list, which allows you to choose between the zimont or the peters model constants for the Zimont premixed combustion model. (This section will appear only if Premixed Combustion or Partially Premixed Combustion is the selected Model and if the C Equation or G Equation premixed model is chosen.)

Turbulent Length Scale Constant

specifies the value of in Equation 9–11 in the Theory Guide.

Turbulent Flame Speed Constant

specifies the value of in Equation 9–9 in the Theory Guide.

Stretch Factor Coefficient

specifies the value of in Equation 9–16 in the Theory Guide.

Turbulent Schmidt Number

specifies the value of in Equation 9–1 in the Theory Guide.

Wall Damping Coefficient

specifies the value of in Equation 9–19.

Ewald Corrector

is enabled by default and described in Peters Flame Speed Model.

G Equation Settings

allows you to select either the transport equation or algebraic option for the calculation of the flame distance variance. Consult Peters Flame Speed Model in the Theory guide for the variance transport and algebraic equation expressions (Equation 9–6 and Equation 9–7).

Flame Curvature Source

includes the curvature source term in the G-Equation, which is the last term in Equation 9–4.

Turbulence-Chemistry Interaction

is available if you select Flamelet Generated Manifold for the partially premixed combustion model. The three available options (Finite-Rate, Turbulent Flame Speed, and Finite-Rate/Turbulent Flame Speed) are discussed in FGM Turbulent Closure in the Theory Guide.

Variance Settings

is available for the G Equation and C Equation. (This section will appear only if Premixed Combustion or Partially Premixed Combustion is the selected Model.)

Variance Method

contains a drop-down list of the available two options: transport equation and algebraic. Consult Peters Flame Speed Model in the Theory Guide for the variance transport and algebraic equation expressions (Equation 9–6 and Equation 9–7). It is recommended that you use the transport equation option for RANS and the algebraic option for LES.

Premixed Combustion Model Options

contains options for the premixed combustion model. (This section will appear only if Premixed Combustion is the selected Model.)

Adiabatic

enables the adiabatic premixed combustion model, which calculates temperature using Equation 9–65 in the Theory Guide.

Non-Adiabatic

enables the non-adiabatic premixed combustion model, which calculates temperature using Equation 9–66 in the Theory Guide.

Premixed Model

contains options for choosing a premixed model.

C Equation

allows you to choose the C equation as described in C-Equation Model Theory.

Extended Coherent Flamelet Model

allows you to choose the Extended Coherent Flamelet model as described in Extended Coherent Flamelet Model Theory.

G Equation

allows you to choose the G equation as described in G-Equation Model Theory.

Extended Coherent Flamelet Model Constants

contains model constants for the Extended Coherent Flame Model. (This section will appear only if Premixed Combustion or Partially Premixed Combustion is the selected Model and if the Extended Coherent Flame Model flame speed model is chosen.) See Modifying the Constants for the ECFM Flame Speed Closure for details.

ITNFS Treatment

contains a drop-down list of the available ITNFS treatments: constant-delta, meneveau, blint, poinsot, and constant.

ITNFS Flame Thickness

sets the flame thickness (Equation 9–29 in the Theory Guide).

Turbulent Schmidt Number

set the turbulent Schmidt number ().

Wall Flux Coefficient

set the wall flux coefficient.

PDF Transport Options

contains options for the Composition PDF Transport combustion model. (This section will appear only if Composition PDF Transport is the selected Model.)

Lagrangian

solves the composition PDF transport equation by stochastically tracking Lagrangian particles through the domain.

Eulerian

assumes a shape for the PDF, allowing Eulerian transport equations to be derived.

Mixing

tab contains the mixing models.

Mixing Model

contains options to specify the method for modeling molecular diffusion. (This section will appear only if Composition PDF Transport is the selected Model.) See Particle Mixing in the Theory Guide for details.

Modified Curl

enables the modified curl model for molecular diffusion.

IEM

enables the IEM model for molecular diffusion.

EMST

enables the EMST mixing model for molecular diffusion.

Mixing Constant

specifies the value of the mixing constant in Equation 11–6 and Equation 11–8 in the Theory Guide.

Boundary

tab allows you to define the fuel and oxidizer compositions. This is only available if you select Eulerian as the PDF Transport Option.

Species

consists of the fuel species and the oxidizer.

Fuel

is the mole or mass fraction of the fuel stream. The sum of mass or mole fractions of all species in the fuel stream should be 1.

Oxidizer

is the mole or mass fraction of the oxidizer stream. The sum of mass or mole fractions of all species in the fuel oxidizer stream should be 1.

Specify Species in

specifies the species as a Mass Fraction or Mole Fraction.

Control

tab contains Lagrangian PDF transport parameters.

PDF Transport Parameters

allows you to set the Particles Per Cell.

Particles Per Cell

sets the number of PDF particles per cell. Higher values of this parameter will reduce statistical error, but increase computational time.

Local Time Stepping

toggles the calculation of local time steps. If this option is disabled, then you will need to specify the Time Step directly (see Equation 11–4 in the Theory Guide). This option is available for steady-state simulations.

Convection #

specifies the particle convection number (see in Equation 11–4 in the Theory Guide).

Diffusion #

specifies the particle diffusion number (see in Equation 11–4 in the Theory Guide).

Mixing #

specifies the particle mixing number (see in Equation 11–4 in the Theory Guide).


Release 18.2 - © ANSYS, Inc. All rights reserved.