37.8.21. Velocity Inlet Dialog Box

The Velocity Inlet dialog box sets the boundary conditions for a velocity inlet zone. It is opened from the Boundary Conditions Task Page. See Inputs at Velocity Inlet Boundaries for details about defining the items below.

Controls

Zone Name

sets the name of the zone.

Phase

displays the name of the phase. This item appears if the VOF, mixture, or Eulerian multiphase model is being used.

Open Channel Wave BC

allows you to set specific parameters for a particular boundary for open channel wave boundaries. This is available when the volume of fluid multiphase model is selected.

Momentum

contains the momentum parameters.

Velocity Specification Method

sets the method used to define the inflow velocity.

Flow Direction Specification Method

sets the method used to define the direction of flow of the wave. This is available when you enable the Open Channel Wave BC option.

Magnitude and Direction

allows specification in terms of a Velocity Magnitude and Flow-Direction.

Components

allows specification in terms of the Cartesian, cylindrical, or local cylindrical velocity components.

Magnitude, Normal to Boundary

allows specification of a Velocity Magnitude normal to the boundary.

Reference Frame

specifies relative or absolute velocity inputs. You can choose to enter Absolute velocities or velocities Relative to Adjacent Cell Zone. If you are not using moving reference frames, both options are equivalent, so you need not choose.

Uniform Flow Velocity Magnitude

is the flow velocity, specified as a constant or a parameter.

Coordinate System

specifies whether Cartesian, Cylindrical, or Local Cylindrical velocities will be defined. This item will appear only for 3D cases in which you have selected Magnitude and Direction or Components as the Velocity Specification Method.

X-, Y-, Z-Velocity

set the components of the velocity vector at the inflow boundary. These items will appear for 2D non-axisymmetric models, or for 3D models if you select the Components option as the Velocity Specification Method and Cartesian as the Coordinate System.

Radial-, Tangential-, Axial-Velocity

set the components of the velocity vector at the inflow boundary. These items will appear for 3D models if you select the Components option as the Velocity Specification Method and Cylindrical or Local Cylindrical as the Coordinate System.

Axial-, Radial-, Swirl-Velocity

set the components of the velocity vector at the inflow boundary. These items will appear for 2D axisymmetric models.


Important:   Swirl-Velocity will appear only for 2D axisymmetric swirl models.


Angular Velocity

specifies the angular velocity for a 3D flow. This item will appear for a 3D model if you select the Components option as the Velocity Specification Method and Cylindrical or Local Cylindrical as the Coordinate System.

Swirl Angular Velocity

specifies the swirl angular velocity for an axisymmetric swirling flow. This item will appear for an axisymmetric swirl model if you choose Components as the Velocity Specification Method.

Velocity Magnitude

sets the magnitude of the velocity vector at the inflow boundary. This item will appear if you select the Magnitude and Direction or Magnitude, Normal to Boundary option as the Velocity Specification Method.

X-, Y-, Z-Component of Flow Direction

set the direction of the velocity vector at the inflow boundary. These items will appear for 2D non-axisymmetric models if you select the Magnitude and Direction option as the Velocity Specification Method, or for 3D models if you select the Magnitude and Direction option as the Velocity Specification Method and Cartesian as the Coordinate System.

Radial-, Tangential-, Axial-Component of Flow Direction

set the direction of the velocity vector at the inlet boundary. These items will appear for 3D models if you select the Magnitude and Direction option as the Velocity Specification Method and Cylindrical or Local Cylindrical as the Coordinate System, or for 2D axisymmetric models.


Important:   Tangential-Velocity will appear only for 2D axisymmetric swirl models.


Axis Origin

sets the X, Y, and Z coordinates of the origin of the local cylindrical coordinate system.

Axis Direction

sets the X, Y, and Z components of the direction of the local cylindrical coordinate system.

Outflow Gauge Pressure

specifies the pressure to be used as the pressure outlet condition if flow exits the domain at any face on the velocity inlet boundary. (Note that this effect is similar to that of the “velocity far-field” boundary that was available in RAMPANT 3.)

This item appears only for the density-based solvers.

Turbulence

contains the turbulence parameters.

Specification Method

specifies which method will be used to define the turbulence parameters. You can choose K and Epsilon (-  models and RSM only), K and Omega (-  models only), Intensity and Length Scale, Intensity and Viscosity Ratio, Intensity and Hydraulic Diameter, Modified Turbulent Viscosity (Spalart-Allmaras model only), or Turbulent Viscosity Ratio (Spalart-Allmaras model only). See Determining Turbulence Parameters for information about the inputs for each of these methods. (This item will appear only for turbulent flow calculations.)

Turbulent Kinetic Energy, Turbulent Dissipation Rate

set values for the turbulence kinetic energy and its dissipation rate . These items will appear if you choose K and Epsilon as the Specification Method.

Turbulent Kinetic Energy, Specific Dissipation Rate

set values for the turbulence kinetic energy and its specific dissipation rate . These items will appear if you choose K and Omega as the Specification Method.

Turbulent Intensity, Turbulent Length Scale

set values for turbulence intensity and turbulence length scale . These items will appear if you choose Intensity and Length Scale as the Specification Method.

Turbulent Intensity, Turbulent Viscosity Ratio

set values for turbulence intensity and turbulent viscosity ratio . These items will appear if you choose Intensity and Viscosity Ratio as the Specification Method.

Turbulent Intensity, Hydraulic Diameter

set values for turbulence intensity and hydraulic diameter . These items will appear if you choose Intensity and Hydraulic Diameter as the Specification Method.

Modified Turbulent Viscosity

sets the value of the modified turbulent viscosity . This item will appear if you choose Modified Turbulent Viscosity as the Specification Method.

Turbulent Viscosity Ratio

sets the value of the turbulent viscosity ratio . This item will appear if you choose Turbulent Viscosity Ratio as the Specification Method.

Turbulent Intensity

sets the value of the turbulence intensity for the LES model.

Reynolds-Stress Specification Method

specifies which method will be used to determine the Reynolds stress boundary conditions when the Reynolds stress turbulence model is used. You can choose either K or Turbulent Intensity or Reynolds-Stress Components. If you choose the former, ANSYS Fluent will compute the Reynolds stresses for you. If you choose the latter, you will explicitly specify the Reynolds stresses yourself. See Reynolds Stress Model for details. (This item will appear only for RSM turbulent flow calculations.)

UU, VV, WW, UV, VW, UW Reynolds Stresses

specify the Reynolds stress components when Reynolds-Stress Components is chosen as the Reynolds-Stress Specification Method.

Acoustic Wave Model

contains settings for treatment of acoustic pressure waves at the boundary.

Off

disables special treatment of acoustic pressure waves at the boundary.

Non Reflecting

enables the general non-reflecting boundary condition treatment described in General Non-Reflecting Boundary Conditions.

Impedance

enables the impedance boundary condition treatment described in Impedance Boundary Conditions.

Transparent Flow Forcing

enables the transparent flow forcing boundary condition described in Transparent Flow Forcing Boundary Conditions.

Impedance Parameters

contains the parameters for the impedance boundary condition treatment. For details refer to Using the Impedance Boundary Condition.

Transparent Flow Forcing Parameters

contains the parameters for the transparent flow forcing boundary condition treatment. For details refer to Using the Transparent Flow Forcing Boundary Condition.

Thermal

contains the thermal parameters.

Temperature

specifies the static temperature of the flow.

Radiation

contains the boundary conditions for the radiation model at the velocity inlet.

External Black Body Temperature Method, Internal Emissivity

set the radiation boundary conditions when you are using the P-1, DTRM, DO, S2S, or MC models for radiation heat transfer. See Defining Boundary Conditions for Radiation for details.

Participates in Solar Ray Tracing

specifies whether or not the velocity inlet participates in solar ray tracing.

Solar Transmissivity Factor

specifies a multiplier (ranging from 0 to 1) that is applied to the solar irradiation entering the domain through the velocity inlet.

Participates in View Factor Calculation

specifies whether or not the velocity inlet participates in the view factor calculation as part of the S2S radiation model. This parameter is available only if you select the Surface to Surface radiation model.

Species

contains the species parameters.

Specify Species in Mole Fractions

allows you to specify the species in mole fractions rather than mass fractions.

Species Mass Fractions

contains inputs for the mass fractions of defined species. See Defining Cell Zone and Boundary Conditions for Species for details about these inputs. These items will appear only if you are modeling non-reacting multi-species flow or you are using the finite-rate reaction formulation.

Mean Mixture Fraction, Mixture Fraction Variance

set inlet values for the PDF mixture fraction and its variance. These items will appear only if you are using the non-premixed or partially premixed combustion model.

Secondary Mean Mixture Fraction, Secondary Mixture Fraction Variance

set inlet values for the secondary mixture fraction and its variance. (These items will appear only if you are using the non-premixed or partially premixed combustion model with two mixture fractions.)

Progress Variable

sets the value of the progress variable for premixed turbulent combustion. See Setting Boundary Conditions for the Progress Variable for details.

This item will appear only if the premixed or partially premixed combustion model is used.

DPM

contains the discrete phase parameters.

Discrete Phase BC Type

sets the way that the discrete phase behaves with respect to the boundary. This item appears when one or more injections have been defined.

reflect

rebounds the particle off the boundary with a change in its momentum as defined by the coefficient of restitution. (See Particle Reflection at Wall in the Fluent Theory Guide.)

trap

terminates the trajectory calculations and records the fate of the particle as “trapped”. In the case of evaporating droplets, their entire mass instantaneously passes into the vapor phase and enters the cell adjacent to the boundary. See Figure 23.25: “Trap” Boundary Condition for the Discrete Phase.

escape

reports the particle as having “escaped” when it encounters the boundary. Trajectory calculations are terminated. See Figure 23.26: “Escape” Boundary Condition for the Discrete Phase.

wall-jet

indicates that the direction and velocity of the droplet particles are given by the resulting momentum flux, which is a function of the impingement angle. See Figure 16.6: “Wall Jet” Boundary Condition for the Discrete Phase in the Theory Guide.

user-defined

specifies a user-defined function to define the discrete phase boundary condition type.

Discrete Phase BC Function

sets the user-defined function from the drop-down list.

Multiphase

contains the multiphase parameters.

Volume Fraction

specifies the volume fraction of the secondary phase selected in the Boundary Conditions Task Page. This section of the dialog box will appear when one of the multiphase models is being used. See Defining Multiphase Cell Zone and Boundary Conditions for details.

Secondary Phase for Inlet

specifies the secondary phase to which the parameters are applied. In case of a three-phase flow, select the corresponding secondary phase from this list.

Wave BC Options

allows you to choose between Shallow Waves, Shallow/Intermediate Waves or Short Gravity Waves. Information about the two types of waves is available in Open Channel Wave Boundary Conditions in the Theory Guide.

Free Surface Level

is determined by using the absolute value of height from the free surface to the origin in the direction of gravity and applying the correct sign based on whether the free surface level is above (positive) or below (negative) the origin.

Bottom Level

is valid for shallow and intermediate waves. The bottom level is used for calculating the liquid height.

Reference Wave Direction

is the direction of wave propagation for a zero wave heading angle.

Wave Modeling Options

determines whether to use wave theory or a wave spectrum to model waves in the shallow/intermediate and short gravity wave regimes.

Number of Waves

specifies the number of waves you are defining when modeling waves using wave theory.

Wave Theory

allows you to choose from First Order Airy (the default), Second Order Stokes, Third Order Stokes, Fourth Order Stokes, and Fifth Order Stokes for shallow/intermediate waves and short gravity waves. For shallow waves, you can choose between Fifth Order Solitary and Fifth Order Cnoidal. Information about the types of wave theory is available in Open Channel Wave Boundary Conditions in the Theory Guide.

Wave Height

is the height difference between a wave crest to the neighboring trough.

Since a solitary wave does not have troughs, the wave height is the distance between a wave crest to mean free surface level.

Wave Length

is the wave length of the shallow wave or short gravity wave.

Inlet Offset Distance

is the translational distance from the reference point origin in the reference wave propagation direction. This option is used to generate a wave from a location other than the reference frame origin.

Phase Difference

is the phase difference between one wave and another.

Wave Heading Angle

is the angle between the direction of the wavefront and the reference wave direction, in the plane of the flow surface. In 2D, there are only two possibilities, zero degrees when the wave is in the reference wave direction, and 180 degrees when the wave is in the opposite direction.

Frequency Spectrum Method

specifies the spectrum to use. You can select Pierson-Moskowitz (appropriate for fully-developed seas), Jonswap (appropriate for fetch-limited seas), or TMA (appropriate for fetch-limited, finite-depth seas).

Peak Shape Parameter

controls the shape and amplitude of the frequency peak in the Jonswap and TMA formulations. This corresponds to in Equation 17–100 in the Fluent Theory Guide.

Significant Wave Height

is the mean wave height of the largest 1/3 of waves. This corresponds to in Equation 17–99 in the Fluent Theory Guide.

Peak Wave Frequency

is the wave frequency corresponding to the highest wave energy. This corresponds to in Equation 17–99 and Equation 17–100 in the Fluent Theory Guide. can be expressed in terms of the peak wave period, , as .

Minimum/Maximum Wave Frequency

specify the frequency range for the spectrum. Note that the Peak Wave Frequency must fall in between Minimum Wave Frequency and Maximum Wave Frequency.

Number of Frequency Components

specifies the number of components into which the frequency spectrum is divided.

Direction Spreading Method

specifies the method to use for specifying the directional spreading characteristics. You can choose Unidirectional (for long-crested waves), Frequency Independent Cosine Function (for short-crested waves where the directional component does not depend on frequency), and Frequency Dependant Hyperbolic Function (for short-crested waves where the directional component depends on frequency).

Frequency Independent Cosine Exponent

specifies the exponent in the Frequency Independent Cosine Function formulation. This corresponds to in Equation 17–104 in the Fluent Theory Guide.

Mean Wave Heading Angle

specifies the principal wave heading direction.

Angular Spread

specifies the deviation from the mean wave direction for calculating the angular range.

Number of Angular Components

specifies the number of components into which the angular range is divided.

Potential

displays the boundary conditions for the electric potential field. This tab is available only if you have enabled either the Electric Potential model or the Electrochemical reaction model in the Species Dialog Box.

Potential Boundary Condition

is a drop-down list of available potential boundary condition types: Specified Flux and Specified Value. For the Specified Flux boundary condition, you will need to specify Current Density at the wall. For the Specified Value boundary condition, you will need to specify Potential at the wall.

UDS

contains the UDS parameters.

User-Defined Scalar Boundary Condition

appears only if user-defined scalars are specified.

User Scalar n

specifies whether the scalar is a specified flux or a specified value.

User-Defined Scalar Boundary Value

appears only if user-defined scalars are specified.

User Scalar n

specifies the value of the scalar.


Release 18.2 - © ANSYS, Inc. All rights reserved.