The Wall dialog box sets the boundary conditions for a wall zone. It is opened from the Boundary Conditions Task Page. See Inputs at Wall Boundaries for details about defining the items below.

Controls
sets the name of the zone.
displays the name of the phase. This item appears if the VOF, mixture, or Eulerian multiphase model is being used.
shows the name of the cell zone adjacent to the wall. (This is for informational use only; you cannot edit this field.)
displays the momentum boundary conditions.
contains options for specifying whether or not the wall is moving.
specifies that the wall is not moving relative to the adjacent cell zone.
enables specification of the tangential wall motion. Tangential wall motion is applicable only to viscous flows. Since the inviscid slip condition decouples the tangential wall velocity from the governing equations, tangential wall motion has no effect on inviscid flow.
contains inputs related to wall motion. See Velocity Conditions for Moving Walls for details.
enables the specification of a wall velocity relative to the velocity of the adjacent cell zone.(If the adjacent cell zone is not moving, this is equivalent to Absolute.)
enables the specification of an absolute wall velocity,
enables the specification of a translational wall velocity.
enables the specification of a rotational wall velocity.
enables the specification of wall velocity components.
sets the translational or rotational speed of the wall (depending on whether you selected Translational or Rotational).
sets the direction vector of the translational velocity. (This item will appear if you have chosen the Translational option.)
sets the coordinates of the origin of the axis of rotation, thereby determining the location of the axis. (This item will appear if you have chosen the Rotational option for a non-axisymmetric case.)
sets the direction vector for the axis of rotation. (This item will appear if you have chosen the Rotational option for a non-axisymmetric case.)
sets the X, Y, and Z-Velocity components of the wall motion. (This item will appear if you have chosen the Components option.)
contains options for specifying the shear conditions at the wall.
specifies a no-slip condition at the wall. No further inputs are required.
enables specification of zero or nonzero shear. See Specified Shear for details. This option is not available for moving walls.
enables the specification of shear stress caused by the variation of surface tension due to temperature. This option is not available for moving walls.
contains inputs related to wall shear. These items will appear when Specified Shear is selected as the Shear Condition. See Specified Shear for details.
specify the ,
, and
or swirl components of shear for a slip wall. Swirl
Component is available only for axisymmetric swirl cases.
is used in multiphase granular flow. You can specify the specularity coefficient such that when the value is zero, this condition is equivalent to zero shear at the wall, but when the value is near unity, there is a significant amount of lateral momentum transfer.
allows you to enter a value between zero and one, which controls the amount of lateral momentum transfer.
contains inputs related to Marangoni stress. This item will appear when Marangoni Stress is selected as the Shear Condition. See Marangoni Stress for details.
specifies the surface tension gradient with respect to temperature ( in Equation 6–100).
contains various models for defining wall roughness size/height in turbulent calculations.
uses the standard wall roughness methods for most turbulence models. See Wall Roughness Effects in Turbulent Wall-Bounded Flows for details.
contains various models for use only with the Spalart-Allmaras and SST k-ω turbulence models. Specifically applicable to icing simulations, choose from Specified Roughness, NASA Correlation, Shin-et-al, or ICE3D Roughness File methods to specify the Sand-Grain Roughness. See Additional Roughness Models for Icing Simulations for details.
contains inputs related to wall adhesion. This section of the dialog box will appear if you are using the VOF model and have enabled wall adhesion in the e Phase Interaction Dialog Box.
specifies the contact angle at the wall for each pair of phases ( in Figure 24.31: Measuring the Contact Angle in the Theory Guide). See Steps for Setting Boundary Conditions for details.
contains the thermal parameters. This tab is available only when the energy equation is turned on.
contains radio buttons for selecting the thermal boundary condition type. See Thermal Boundary Conditions at Walls for details about these inputs:
selects a specified heat flux condition.
selects a specified wall temperature condition.
selects a convective heat transfer boundary condition model.
selects an external radiation boundary condition.
selects a combined convection/external radiation boundary condition.
selects a coupled heat transfer condition. It is applicable only to walls that form the interface between two regions (such as the fluid/solid interface for a conjugate heat transfer problem).
selects a heat transfer condition where a boundary can receive thermal data (either wall temperature or heat flow) from the System Coupling service. It is applicable when ANSYS Fluent is coupled with another system in Workbench using System Coupling (see Heat Transfer Boundary Conditions Through System Coupling for details).
specifies that the thermal data is interpolated across a mapped interface. It is available only for the interface wall boundary zones created as part of a mapped interface (see Heat Transfer Boundary Conditions Across a Mapped Interface for details).
Once a condition type has been selected, the appropriate conditions can be specified.
sets the wall heat flux to be used for the Heat Flux condition. A specification of zero Heat Flux is simply the adiabatic condition (no heat transfer). A positive value of heat flux implies that heat enters into the domain.
sets the wall temperature to be used for the Temperature condition.
sets the convective heat transfer coefficient to be used for the
Convection condition ( in Equation 6–119).
sets the reference or free stream temperature to be used for the
Convection condition ( in Equation 6–119).
sets the emissivity of the external wall to be used for the
Radiation condition ( in Equation 6–120).
sets the temperature of the external radiation source/sink to be used for the
Radiation condition ( in Equation 6–120).
sets the internal emissivity of the wall. This item will appear only if you are using the gray P-1, DO, MC, DTRM, or S2S models for radiation heat transfer. (Note that it will not appear if you are using the non-gray P-1, DO, or MC model. In these cases, you will enter the Internal Emissivity for each band in the Radiation tab.)
sets the thickness of a thin wall for the calculation of thermal resistance. (See Thin-Wall Thermal Resistance Parameters for details.)
sets the rate of heat generation in a wall without shell conduction.
sets the contact resistance ( in Equation 18–23 in the Theory Guide) at the wall. See Modeling Solidification and Melting for details. This item appears only when the
solidification/melting model is used.
sets the material type for a thin wall. The conductivity of the material is used for the calculation of thin-wall thermal resistance. (See Thin-Wall Thermal Resistance Parameters for details.) Material is used only when Wall Thickness is nonzero. Materials are defined with the Materials Task Page.
enables shell conduction for the wall. See Shell Conduction for details.
is only available when Shell Conduction is enabled, and opens the Shell Conduction Layers Dialog Box in order to allow you to define the shell conduction settings for the wall.
displays the boundary conditions for the S2S model, the DO model, the MC model, and the non-gray P-1 model at the wall. This tab is only available if you are using the surface to surface model, the discrete ordinates model, the Monte Carlo model, or the non-gray P-1 model. See Forming Surface Clusters, Wall Boundary Conditions for the DO Model, and Wall Boundary Conditions for the DTRM, and the P-1, S2S, and Rosseland Models for details.
contains a drop-down list of available radiation boundary condition types. The available options are opaque and semi-transparent. This item will appear only if you are using the discrete ordinates or Monte Carlo model.
specifies the internal emissivity of the wall in each wavelength band. This item will appear only if you are using the non-gray discrete ordinates or Monte Carlo models and you have selected opaque as the BC Type, or if you are using the non-gray P-1 model.
specifies the fraction of the irradiation that is to be treated as diffuse. By default, the Diffuse Fraction is set to 1, indicating that all of the irradiation is diffuse. If the non-gray DO or MC model is being used, the Diffuse Fraction can be specified for each band. This item will appear only if you are using the Monte Carlo or discrete ordinates model.
specifies the beam width for an external semi-transparent wall in terms of the Theta and Phi extents. This item will appear only if you are using the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.
specifies the beam direction as an X,Y,Z vector. You can specify the Beam Direction as a constant, a profile, or a user-defined function. This item will appear only if you are using the Monte Carlo model or the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.
specifies the value of the irradiation flux. If the non-gray DO or MC models are being used, a constant Direct Irradiation can be specified for each band.
This item will appear only if you are using the Monte Carlo model or the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.
is the default means of specifying the scale of irradiation flux. When enabled, ANSYS Fluent assumes that the value of Direct Irradiation that you specify is the irradiation flux parallel to the Beam Direction. When deselected, ANSYS Fluent instead assumes that the value specified is the flux parallel to the face normals and will calculate the resulting beam parallel flux for every face. This item will appear only if you are using the discrete ordinates model.
specifies the value of the irradiation flux. If the non-gray DO model is being used, a constant Diffuse Irradiation can be specified for each band.
This item will appear only if you are using the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.
contains the settings for solar ray tracing. This group box is available only if you select Solar Ray Tracing from the Model list in the Solar Load group box of the Radiation Model dialog box. For semitransparent coupled walls, the solar ray tracing settings are defined on the original wall and not on the shadow wall. See Solar Ray Tracing for details.
specifies whether or not the wall participates in solar ray tracing.
contains the settings that define the absorptivity of wall.
specifies a multiplier (ranging from 0 to 1) that is applied to the visible portion of the direct solar radiation spectrum to account for the absorption of the wall. The value should be defined for normal incident rays.
specifies a multiplier (ranging from 0 to 1) that is applied to the infrared portion of the direct solar radiation spectrum to account for the absorption of the wall. The value should be defined for normal incident rays.
specifies a multiplier (ranging from 0 to 1) that is applied to the diffuse solar radiation to account for the absorption of the wall. This setting is only available for semi-transparent walls.
contains the settings that define the transmissivity of wall. This group box is only available when semi-transparent is selected for BC Type.
specifies a multiplier (ranging from 0 to 1) that is applied to the visible portion of the direct solar radiation spectrum to account for the transmissivity of the wall. The value should be defined for normal incident rays. This setting is only available for semi-transparent walls.
specifies a multiplier (ranging from 0 to 1) that is applied to the infrared portion of the direct solar radiation spectrum to account for the transmissivity of the wall. The value should be defined for normal incident rays. This setting is only available for semi-transparent walls.
specifies a multiplier (ranging from 0 to 1) that is applied to the diffuse solar irradiation to account for the transmissivity of the wall. This setting is only available for semi-transparent walls.
contains the settings for the S2S radiation model. This group box is available only if you select the Surface to Surface radiation model. See Forming Surface Clusters for details.
sets the number of faces per surface cluster (FPSC) for the wall, and thus controls the number of radiating surfaces and (if you select Cluster to Cluster for Basis in the View Factors and Clustering dialog box) view factor surfaces.
specifies that the wall is a critical zone. When this option is enabled, the value entered for Faces Per Surface Cluster will not be altered when you use Automatic clustering in the View Factors and Clustering dialog box, and impacts the calculations and actions performed by the buttons in the Maximum Distance from Critical Zone group box of the Participating Boundary Zones dialog box.
specifies whether or not the wall participates in the view factor calculation as part of the S2S radiation model. This option is available only if you select the Surface to Surface radiation model.
contains the species parameters. This tab is available only if you have enabled the Species Transport model in the Species Model Dialog Box.
activates reactions at the wall. This item will appear only if you have enabled any of the reactions in the Species Model Dialog Box.
allows you to specify a defined group, or mechanism, of available reactions. This item will appear only if the Reaction option has been turned on. See Defining Zone-Based Reaction Mechanisms for details about defining reaction mechanisms.
allows you to specify a factor, which multiplies the wall area to account for the increased surface area of washcoats. This item will appear only if the Reaction option has been turned on. See Species Boundary Conditions for Walls for details.
contains options for the specification of species boundary conditions. See Species Boundary Conditions for Walls for details.
indicates a zero-flux condition for a species. This is the default condition.
indicates that the species mass fraction will be specified.
contains inputs for the species mass fractions of any species for which you have selected Species Mass Fraction as the Species Boundary Condition.
contains the discrete phase parameters. This tab is available only if you have defined at least one injection.
contains inputs for setting the fate of particle trajectories at the wall. These options will appear when one or more injections have been defined. See Setting Boundary Conditions for the Discrete Phase for details.
sets the way that the discrete phase behaves with respect to the boundary.
rebounds the particle off the boundary with a change in its momentum as defined by the coefficients of restitution (see Particle Reflection at Wall in the Fluent Theory Guide). When at least one injection accounts for the rough wall model (the Rough Wall Model option is selected under the Physical Models tab in the Set Injections Properties dialog box), you can specify the DPM Wall Roughness Parameters (Ra, Rq, and RSm in Equation 16–220 in the Fluent Theory Guide). (See Rough Wall Model).
terminates the trajectory calculations and records the fate of the particle as “trapped”. In the case of evaporating droplets, their entire mass instantaneously passes into the vapor phase and enters the cell adjacent to the boundary. See Figure 23.25: “Trap” Boundary Condition for the Discrete Phase.
reports the particle as having “escaped” when it encounters the boundary. Trajectory calculations are terminated. See Figure 23.26: “Escape” Boundary Condition for the Discrete Phase.
indicates that the direction and velocity of the droplet particles are given by the resulting momentum flux, which is a function of the impingement angle. See Figure 16.6: “Wall Jet” Boundary Condition for the Discrete Phase in the Theory Guide.
allows you to enable Film Condensation (Film Condensation Model), Wall Boundary Layer Model (Wall Boundary Layer Model), and specify the Film Model Parameters:
is used to model splashing. The minimum number of splashed parcels is three. A value of zero implies no splashing.
is used to determine the transition temperature (Equation 16–226 and Equation 16–254 in the Fluent Theory Guide for the stanton-rutland and kuhnke splashing models, respectively).
(default) consists of four regimes, namely, stick, rebound, spread, and splash, which are based on the impact energy and wall temperature. See The Stanton-Rutland Model in the Fluent Theory Guide for more details.
consists of four regimes: spread, rebound, splash, and dry splash (thermal breakup). See The Kuhnke Model in the Fluent Theory Guide for more details. You must specify the following DPM Wall Roughness Parameters:
is used to compute in Equation 16–262 in the Fluent Theory Guide.
Roughness Rz: is used to compute splashed droplets ejection angle in Equation 16–274 in the Fluent Theory Guide.
specifies a user-defined function to define the discrete phase boundary condition type.
sets the user-defined function from the drop-down list.
determine the behavior of reflecting particles. This item appears when reflect is chosen as the Boundary Cond. Type. See Discrete Phase Boundary Condition Types for details on setting the following items.
sets the type of function for the normal coefficient of restitution. This function can be constant, piecewise-linear, piecewise-polynomial, or polynomial.
sets the type of function for the tangential coefficient of restitution. This function can be constant, piecewise-linear, piecewise-polynomial, or polynomial.
contains a list of names to designate the collision partner.
contains a list of erosion models. See Setting Particle Erosion and Accretion Parameters for details about these items.
specifies erosion rates to be computed using the generic erosion model. (See Accretion in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Generic Erosion Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.
specifies erosion rates to be computed using the Finnie formulation. (See Accretion in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Finnie Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.
specifies erosion rates to be computed using the McLaury formulation. (See McLaury Erosion Model in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the McLaury Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.
specifies erosion rates to be computed using the Oka formulation. (See Oka Erosion Model in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Oka Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.
specifies in Equation 16–213 and Equation 16–218 in the Fluent Theory Guide as a
constant or a piecewise-linear,
piecewise-polynomial, or polynomial function of
relative velocity. This item appears only when Enable Rotation is
selected under the Physical Model tab of the Set Injection Properties Dialog Box.
displays the boundary conditions for user-defined scalars (UDSs) at the wall. This tab is available only if you have specified a nonzero number of user-defined scalars in the User-Defined Scalars Dialog Box.
contains options for the specification of UDS boundary conditions. See the separate Fluent Customization Manual for details.
indicates that the flux of the UDS at the wall will be specified.
indicates that the value for the UDS at the wall will be specified.
contains inputs for the value of the flux of the UDS, or the value of the UDS itself, depending on your selection for that UDS under User Defined Scalar Boundary Condition.
displays the boundary conditions for liquid films at the wall. This tab is available only if you have enabled the Eulerian Wall Film model in the Models Task Page.
allows you to define a film wall condition for any wall. See Modeling Eulerian Wall Films for details. Once this option is enabled, you can set the following:
allows you to select the desired condition type.
allows you to specify settings for boundary Film Conditions:
The film mass source in terms of mass flux per unit area (kg/m2–s).
The film momentum source in terms of momentum flux per unit area (N/m2).
The film temperature (K).
The film passive scalar source in terms of mass flux per unit area (kg/m2–s).
allows you to specify settings for initial Film Conditions:
The film height at the wall boundary.
The film velocity components at the wall boundary.
The film temperature (K).
The film passive scalar at the wall boundary (dimensionless).
(moving reference frames or moving walls only) enables specification of the film momentum flux relative to the wall on which liquid film is defined (Boundary Condition type only). This option is only available when Moving Wall is selected in the Wall dialog box and/or Frame Motion is selected in the Fluid dialog box.
(moving reference frames or moving walls only) enables specification of the initial velocity relative to the wall on which liquid film is defined (Initial Condition type only). This option is only available when Moving Wall is selected in the Wall dialog box and/or Frame Motion is selected in the Fluid dialog box.
enables you to specify the additional source terms to the film continuity (Mass Flux), momentum (X-Momentum Flux, Y-Momentum Flux, and Z-Momentum Flux), energy (Heat Flux), and passive scalar equations (Scalar Flux). This option is only available with initial conditions.
When this option is selected, the liquid film and the gas flow will share the same velocity at the interface of the liquid-gas interface using a two-way coupling. When this option is not selected, the coupling between the liquid film and the gas flow is only one-way, namely, while the gas flow impacts the film flow, the film flow does not impact the bulk of the gas flow.
enables the phase change for the selected wall. This option is available only when Phase Change is selected in the Model Options and Setup tab of the Eulerian Wall Film Dialog Box. Once enabled, you can specify the following Phase Change Parameters (see Coupling of Wall Film with Mixture Species Transport in the Theory Guide):
is the value of used in Equation 19–28 in the Theory Guide. You can also specify the condensation rate via a user-defined profile UDF by selecting the name of the compiled UDF from the drop-down list.
is the value of used in Equation 19–28 in the Theory Guide. You can also specify the vaporization rate via a user-defined profile UDF by selecting the name of the compiled UDF from the drop-down list.
contains parameters related to particle-wall impingement
is a drop-down list that contains available impingement models:
stanton-rutland (default): consists of four impingement regimes: stick, rebound, spread and splash, which are based on the impact energy and wall temperature. See The Stanton-Rutland Model in the Fluent Theory Guide for details.
kuhnke: consists of four impingement regimes: stick, rebound, spread and splash (thermal breakup). See The Kuhnke Model in the Fluent Theory Guide for details.
allows you to enable the wall splashing for the selected wall and specify the Number of Splashed Particles. The minimum value is 3. This option is available when Particle Splashing is enabled in the Eulerian Wall Film dialog box.
(available when the kuhnke model is selected from the Impingement Model drop-down list)
enables you to specify wall roughness values used by the Kuhnke model:
Ra: the wall mean roughness that is used to compute in Equation 16–262 in the Fluent Theory Guide
Rz: the average surface roughness that is used to compute splashed particle reflection angle distribution Equation 16–274 in the Fluent Theory Guide.
is the dimensionless variable that is used to determine the impingement regime transition temperature in Equation 16–254 in the Fluent Theory Guide.
displays the boundary conditions for the electric potential field at the wall. This tab is available only if you have enabled either the Electric Potential model under the Model tree branch or the Electrochemical Reaction model in the Species Dialog Box.
enables electrochemical reactions at the wall. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.
(if enabled) includes heat from the electrochemical reaction in the energy equation. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.
contains a drop-down list of all available electrochemical reaction mechanisms. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.
contains a drop-down list of available potential boundary condition types for the external wall. You will need to specify one of the following:
Current Density (Select the Specified Flux potential boundary condition)
Potential at the wall (Select the Specified Value potential boundary condition)
This control is available only for one-sided external walls. For two-sided internal walls, the solver always uses the coupled treatment.
is the contact resistance at the wall, in Equation 20–3 in the Fluent Theory Guide. For two-sided internal walls, you only need to define the contact resistance at one of the walls. The value you specify will be automatically copied to the other side of the wall.