37.8.22. Wall Dialog Box

The Wall dialog box sets the boundary conditions for a wall zone. It is opened from the Boundary Conditions Task Page. See Inputs at Wall Boundaries for details about defining the items below.

Controls

Zone Name

sets the name of the zone.

Phase

displays the name of the phase. This item appears if the VOF, mixture, or Eulerian multiphase model is being used.

Adjacent Cell Zone

shows the name of the cell zone adjacent to the wall. (This is for informational use only; you cannot edit this field.)

Momentum

displays the momentum boundary conditions.

Wall Motion

contains options for specifying whether or not the wall is moving.

Stationary Wall

specifies that the wall is not moving relative to the adjacent cell zone.

Moving Wall

enables specification of the tangential wall motion. Tangential wall motion is applicable only to viscous flows. Since the inviscid slip condition decouples the tangential wall velocity from the governing equations, tangential wall motion has no effect on inviscid flow.

Motion

contains inputs related to wall motion. See Velocity Conditions for Moving Walls for details.

Relative to Adjacent Cell Zone

enables the specification of a wall velocity relative to the velocity of the adjacent cell zone.(If the adjacent cell zone is not moving, this is equivalent to Absolute.)

Absolute

enables the specification of an absolute wall velocity,

Translational

enables the specification of a translational wall velocity.

Rotational

enables the specification of a rotational wall velocity.

Components

enables the specification of wall velocity components.

Speed

sets the translational or rotational speed of the wall (depending on whether you selected Translational or Rotational).

Direction

sets the direction vector of the translational velocity. (This item will appear if you have chosen the Translational option.)

Rotation-Axis Origin

sets the coordinates of the origin of the axis of rotation, thereby determining the location of the axis. (This item will appear if you have chosen the Rotational option for a non-axisymmetric case.)

Rotation-Axis Direction

sets the direction vector for the axis of rotation. (This item will appear if you have chosen the Rotational option for a non-axisymmetric case.)

Velocity Components

sets the X, Y, and Z-Velocity components of the wall motion. (This item will appear if you have chosen the Components option.)

Shear Condition

contains options for specifying the shear conditions at the wall.

No Slip

specifies a no-slip condition at the wall. No further inputs are required.

Specified Shear

enables specification of zero or nonzero shear. See Specified Shear for details. This option is not available for moving walls.

Marangoni Stress

enables the specification of shear stress caused by the variation of surface tension due to temperature. This option is not available for moving walls.

Shear Stress

contains inputs related to wall shear. These items will appear when Specified Shear is selected as the Shear Condition. See Specified Shear for details.

X-Component, Y-Component, Z-Component, Swirl Component

specify the , , and or swirl components of shear for a slip wall. Swirl Component is available only for axisymmetric swirl cases.

Specularity Coefficient

is used in multiphase granular flow. You can specify the specularity coefficient such that when the value is zero, this condition is equivalent to zero shear at the wall, but when the value is near unity, there is a significant amount of lateral momentum transfer.

Specularity Coefficient

allows you to enter a value between zero and one, which controls the amount of lateral momentum transfer.

Marangoni Stress

contains inputs related to Marangoni stress. This item will appear when Marangoni Stress is selected as the Shear Condition. See Marangoni Stress for details.

Surface Tension Gradient

specifies the surface tension gradient with respect to temperature ( in Equation 6–100).

Wall Roughness

contains various models for defining wall roughness size/height in turbulent calculations.

Standard

uses the standard wall roughness methods for most turbulence models. See Wall Roughness Effects in Turbulent Wall-Bounded Flows for details.

High Roughness (Icing)

contains various models for use only with the Spalart-Allmaras and SST k-ω turbulence models. Specifically applicable to icing simulations, choose from Specified Roughness, NASA Correlation, Shin-et-al, or ICE3D Roughness File methods to specify the Sand-Grain Roughness. See Additional Roughness Models for Icing Simulations for details.

Wall Adhesion

contains inputs related to wall adhesion. This section of the dialog box will appear if you are using the VOF model and have enabled wall adhesion in the e Phase Interaction Dialog Box.

Contact Angles

specifies the contact angle at the wall for each pair of phases ( in Figure 24.31: Measuring the Contact Angle in the Theory Guide). See Steps for Setting Boundary Conditions for details.

Thermal

contains the thermal parameters. This tab is available only when the energy equation is turned on.

Thermal Conditions

contains radio buttons for selecting the thermal boundary condition type. See Thermal Boundary Conditions at Walls for details about these inputs:

Heat Flux

selects a specified heat flux condition.

Temperature

selects a specified wall temperature condition.

Convection

selects a convective heat transfer boundary condition model.

Radiation

selects an external radiation boundary condition.

Mixed

selects a combined convection/external radiation boundary condition.

Coupled

selects a coupled heat transfer condition. It is applicable only to walls that form the interface between two regions (such as the fluid/solid interface for a conjugate heat transfer problem).

via System Coupling

selects a heat transfer condition where a boundary can receive thermal data (either wall temperature or heat flow) from the System Coupling service. It is applicable when ANSYS Fluent is coupled with another system in Workbench using System Coupling (see Heat Transfer Boundary Conditions Through System Coupling for details).

via Mapped Interface

specifies that the thermal data is interpolated across a mapped interface. It is available only for the interface wall boundary zones created as part of a mapped interface (see Heat Transfer Boundary Conditions Across a Mapped Interface for details).

Once a condition type has been selected, the appropriate conditions can be specified.

Heat Flux

sets the wall heat flux to be used for the Heat Flux condition. A specification of zero Heat Flux is simply the adiabatic condition (no heat transfer). A positive value of heat flux implies that heat enters into the domain.

Temperature

sets the wall temperature to be used for the Temperature condition.

Heat Transfer Coefficient

sets the convective heat transfer coefficient to be used for the Convection condition ( in Equation 6–119).

Free Stream Temperature

sets the reference or free stream temperature to be used for the Convection condition ( in Equation 6–119).

External Emissivity

sets the emissivity of the external wall to be used for the Radiation condition ( in Equation 6–120).

External Radiation Temperature

sets the temperature of the external radiation source/sink to be used for the Radiation condition ( in Equation 6–120).

Internal Emissivity

sets the internal emissivity of the wall. This item will appear only if you are using the gray P-1, DO, MC, DTRM, or S2S models for radiation heat transfer. (Note that it will not appear if you are using the non-gray P-1, DO, or MC model. In these cases, you will enter the Internal Emissivity for each band in the Radiation tab.)

Wall Thickness

sets the thickness of a thin wall for the calculation of thermal resistance. (See Thin-Wall Thermal Resistance Parameters for details.)

Heat Generation Rate

sets the rate of heat generation in a wall without shell conduction.

Contact Resistance

sets the contact resistance ( in Equation 18–23 in the Theory Guide) at the wall. See Modeling Solidification and Melting for details. This item appears only when the solidification/melting model is used.

Material Name

sets the material type for a thin wall. The conductivity of the material is used for the calculation of thin-wall thermal resistance. (See Thin-Wall Thermal Resistance Parameters for details.) Material is used only when Wall Thickness is nonzero. Materials are defined with the Materials Task Page.

Shell Conduction

enables shell conduction for the wall. See Shell Conduction for details.

Edit...

is only available when Shell Conduction is enabled, and opens the Shell Conduction Layers Dialog Box in order to allow you to define the shell conduction settings for the wall.

Radiation

displays the boundary conditions for the S2S model, the DO model, the MC model, and the non-gray P-1 model at the wall. This tab is only available if you are using the surface to surface model, the discrete ordinates model, the Monte Carlo model, or the non-gray P-1 model. See Forming Surface Clusters, Wall Boundary Conditions for the DO Model, and Wall Boundary Conditions for the DTRM, and the P-1, S2S, and Rosseland Models for details.

BC Type

contains a drop-down list of available radiation boundary condition types. The available options are opaque and semi-transparent. This item will appear only if you are using the discrete ordinates or Monte Carlo model.

Internal Emissivity

specifies the internal emissivity of the wall in each wavelength band. This item will appear only if you are using the non-gray discrete ordinates or Monte Carlo models and you have selected opaque as the BC Type, or if you are using the non-gray P-1 model.

Diffuse Fraction

specifies the fraction of the irradiation that is to be treated as diffuse. By default, the Diffuse Fraction is set to 1, indicating that all of the irradiation is diffuse. If the non-gray DO or MC model is being used, the Diffuse Fraction can be specified for each band. This item will appear only if you are using the Monte Carlo or discrete ordinates model.

Beam Width

specifies the beam width for an external semi-transparent wall in terms of the Theta and Phi extents. This item will appear only if you are using the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.

Beam Direction

specifies the beam direction as an X,Y,Z vector. You can specify the Beam Direction as a constant, a profile, or a user-defined function. This item will appear only if you are using the Monte Carlo model or the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.

Direct Irradiation

specifies the value of the irradiation flux. If the non-gray DO or MC models are being used, a constant Direct Irradiation can be specified for each band.

This item will appear only if you are using the Monte Carlo model or the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.

Apply Direct Irradiation Parallel to the Beam

is the default means of specifying the scale of irradiation flux. When enabled, ANSYS Fluent assumes that the value of Direct Irradiation that you specify is the irradiation flux parallel to the Beam Direction. When deselected, ANSYS Fluent instead assumes that the value specified is the flux parallel to the face normals and will calculate the resulting beam parallel flux for every face. This item will appear only if you are using the discrete ordinates model.

Diffuse Irradiation

specifies the value of the irradiation flux. If the non-gray DO model is being used, a constant Diffuse Irradiation can be specified for each band.

This item will appear only if you are using the discrete ordinates radiation model and you have selected semi-transparent as the BC Type.

Solar Boundary Conditions

contains the settings for solar ray tracing. This group box is available only if you select Solar Ray Tracing from the Model list in the Solar Load group box of the Radiation Model dialog box. For semitransparent coupled walls, the solar ray tracing settings are defined on the original wall and not on the shadow wall. See Solar Ray Tracing for details.

Participates in Solar Ray Tracing

specifies whether or not the wall participates in solar ray tracing.

Absorptivity

contains the settings that define the absorptivity of wall.

Direct Visible

specifies a multiplier (ranging from 0 to 1) that is applied to the visible portion of the direct solar radiation spectrum to account for the absorption of the wall. The value should be defined for normal incident rays.

Direct IR

specifies a multiplier (ranging from 0 to 1) that is applied to the infrared portion of the direct solar radiation spectrum to account for the absorption of the wall. The value should be defined for normal incident rays.

Diffuse Hemispherical

specifies a multiplier (ranging from 0 to 1) that is applied to the diffuse solar radiation to account for the absorption of the wall. This setting is only available for semi-transparent walls.

Transmissivity

contains the settings that define the transmissivity of wall. This group box is only available when semi-transparent is selected for BC Type.

Direct Visible

specifies a multiplier (ranging from 0 to 1) that is applied to the visible portion of the direct solar radiation spectrum to account for the transmissivity of the wall. The value should be defined for normal incident rays. This setting is only available for semi-transparent walls.

Direct IR

specifies a multiplier (ranging from 0 to 1) that is applied to the infrared portion of the direct solar radiation spectrum to account for the transmissivity of the wall. The value should be defined for normal incident rays. This setting is only available for semi-transparent walls.

Diffuse Hemispherical

specifies a multiplier (ranging from 0 to 1) that is applied to the diffuse solar irradiation to account for the transmissivity of the wall. This setting is only available for semi-transparent walls.

S2S Parameters

contains the settings for the S2S radiation model. This group box is available only if you select the Surface to Surface radiation model. See Forming Surface Clusters for details.

Faces Per Surface Cluster

sets the number of faces per surface cluster (FPSC) for the wall, and thus controls the number of radiating surfaces and (if you select Cluster to Cluster for Basis in the View Factors and Clustering dialog box) view factor surfaces.

Critical Zone

specifies that the wall is a critical zone. When this option is enabled, the value entered for Faces Per Surface Cluster will not be altered when you use Automatic clustering in the View Factors and Clustering dialog box, and impacts the calculations and actions performed by the buttons in the Maximum Distance from Critical Zone group box of the Participating Boundary Zones dialog box.

Participates in View Factor Calculation

specifies whether or not the wall participates in the view factor calculation as part of the S2S radiation model. This option is available only if you select the Surface to Surface radiation model.

Species

contains the species parameters. This tab is available only if you have enabled the Species Transport model in the Species Model Dialog Box.

Reaction

activates reactions at the wall. This item will appear only if you have enabled any of the reactions in the Species Model Dialog Box.

Reaction Mechanisms

allows you to specify a defined group, or mechanism, of available reactions. This item will appear only if the Reaction option has been turned on. See Defining Zone-Based Reaction Mechanisms for details about defining reaction mechanisms.

Surface Area Washcoat Factor

allows you to specify a factor, which multiplies the wall area to account for the increased surface area of washcoats. This item will appear only if the Reaction option has been turned on. See Species Boundary Conditions for Walls for details.

Species Boundary Condition

contains options for the specification of species boundary conditions. See Species Boundary Conditions for Walls for details.

Zero Diffusive Flux

indicates a zero-flux condition for a species. This is the default condition.

Specified Mass Fraction

indicates that the species mass fraction will be specified.

Species Mass Fractions

contains inputs for the species mass fractions of any species for which you have selected Species Mass Fraction as the Species Boundary Condition.

DPM

contains the discrete phase parameters. This tab is available only if you have defined at least one injection.

Discrete Phase Model Conditions

contains inputs for setting the fate of particle trajectories at the wall. These options will appear when one or more injections have been defined. See Setting Boundary Conditions for the Discrete Phase for details.

Boundary Cond. Type

sets the way that the discrete phase behaves with respect to the boundary.

reflect

rebounds the particle off the boundary with a change in its momentum as defined by the coefficients of restitution (see Particle Reflection at Wall in the Fluent Theory Guide). When at least one injection accounts for the rough wall model (the Rough Wall Model option is selected under the Physical Models tab in the Set Injections Properties dialog box), you can specify the DPM Wall Roughness Parameters (Ra, Rq, and RSm in Equation 16–220 in the Fluent Theory Guide). (See Rough Wall Model).

trap

terminates the trajectory calculations and records the fate of the particle as “trapped”. In the case of evaporating droplets, their entire mass instantaneously passes into the vapor phase and enters the cell adjacent to the boundary. See Figure 23.25: “Trap” Boundary Condition for the Discrete Phase.

escape

reports the particle as having “escaped” when it encounters the boundary. Trajectory calculations are terminated. See Figure 23.26: “Escape” Boundary Condition for the Discrete Phase.

wall-jet

indicates that the direction and velocity of the droplet particles are given by the resulting momentum flux, which is a function of the impingement angle. See Figure 16.6: “Wall Jet” Boundary Condition for the Discrete Phase in the Theory Guide.

wall-film

allows you to enable Film Condensation (Film Condensation Model), Wall Boundary Layer Model (Wall Boundary Layer Model), and specify the Film Model Parameters:

Number Of Splashed Drops

is used to model splashing. The minimum number of splashed parcels is three. A value of zero implies no splashing.

Critical Temperature Factor

is used to determine the transition temperature (Equation 16–226 and Equation 16–254 in the Fluent Theory Guide for the stanton-rutland and kuhnke splashing models, respectively).

Impingement/Splashing Model
stanton-rutland

(default) consists of four regimes, namely, stick, rebound, spread, and splash, which are based on the impact energy and wall temperature. See The Stanton-Rutland Model in the Fluent Theory Guide for more details.

kuhnke

consists of four regimes: spread, rebound, splash, and dry splash (thermal breakup). See The Kuhnke Model in the Fluent Theory Guide for more details. You must specify the following DPM Wall Roughness Parameters:

Roughness Ra

is used to compute in Equation 16–262 in the Fluent Theory Guide.

Roughness Rz

Roughness Rz: is used to compute splashed droplets ejection angle in Equation 16–274 in the Fluent Theory Guide.

user-defined

specifies a user-defined function to define the discrete phase boundary condition type.

Boundary Cond. Function

sets the user-defined function from the drop-down list.

Discrete Phase Reflection Coefficients

determine the behavior of reflecting particles. This item appears when reflect is chosen as the Boundary Cond. Type. See Discrete Phase Boundary Condition Types for details on setting the following items.

Normal

sets the type of function for the normal coefficient of restitution. This function can be constant, piecewise-linear, piecewise-polynomial, or polynomial.

Tangent

sets the type of function for the tangential coefficient of restitution. This function can be constant, piecewise-linear, piecewise-polynomial, or polynomial.

DEM Collision Partner

contains a list of names to designate the collision partner.

Erosion Model

contains a list of erosion models. See Setting Particle Erosion and Accretion Parameters for details about these items.

Generic Model

specifies erosion rates to be computed using the generic erosion model. (See Accretion in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Generic Erosion Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.

Finnie

specifies erosion rates to be computed using the Finnie formulation. (See Accretion in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Finnie Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.

McLaury

specifies erosion rates to be computed using the McLaury formulation. (See McLaury Erosion Model in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the McLaury Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.

Oka

specifies erosion rates to be computed using the Oka formulation. (See Oka Erosion Model in the Fluent Theory Guide for background information about this model.) When this model is enabled, you must specify the erosion parameters in the Oka Model Parameters dialog box that opens by clicking the corresponding Edit… button as described in Setting Particle Erosion and Accretion Parameters.

Friction Coefficient

specifies in Equation 16–213 and Equation 16–218 in the Fluent Theory Guide as a constant or a piecewise-linear, piecewise-polynomial, or polynomial function of relative velocity. This item appears only when Enable Rotation is selected under the Physical Model tab of the Set Injection Properties Dialog Box.

UDS

displays the boundary conditions for user-defined scalars (UDSs) at the wall. This tab is available only if you have specified a nonzero number of user-defined scalars in the User-Defined Scalars Dialog Box.

User Defined Scalar Boundary Condition

contains options for the specification of UDS boundary conditions. See the separate Fluent Customization Manual for details.

Specified Flux

indicates that the flux of the UDS at the wall will be specified.

Specified Value

indicates that the value for the UDS at the wall will be specified.

User Defined Scalar Boundary Value

contains inputs for the value of the flux of the UDS, or the value of the UDS itself, depending on your selection for that UDS under User Defined Scalar Boundary Condition.

Wall Film

displays the boundary conditions for liquid films at the wall. This tab is available only if you have enabled the Eulerian Wall Film model in the Models Task Page.

Eulerian Film Wall

allows you to define a film wall condition for any wall. See Modeling Eulerian Wall Films for details. Once this option is enabled, you can set the following:

Film Condition Type

allows you to select the desired condition type.

Boundary Condition

allows you to specify settings for boundary Film Conditions:

Film Mass Flux

The film mass source in terms of mass flux per unit area (kg/m2–s).

X-Momentum Flux, Y-Momentum Flux, and Z-Momentum Flux

The film momentum source in terms of momentum flux per unit area (N/m2).

Incoming Film Temperature

The film temperature (K).

Film Passive Scalar Flux

The film passive scalar source in terms of mass flux per unit area (kg/m2–s).

Initial Condition

allows you to specify settings for initial Film Conditions:

Film Height

The film height at the wall boundary.

X-Velocity, Y-Velocity, and Z-Velocity

The film velocity components at the wall boundary.

Film Temperature

The film temperature (K).

Film Passive Scalar

The film passive scalar at the wall boundary (dimensionless).

Relative Film Momentum Flux

(moving reference frames or moving walls only) enables specification of the film momentum flux relative to the wall on which liquid film is defined (Boundary Condition type only). This option is only available when Moving Wall is selected in the Wall dialog box and/or Frame Motion is selected in the Fluid dialog box.

Relative Initial Film Velocity

(moving reference frames or moving walls only) enables specification of the initial velocity relative to the wall on which liquid film is defined (Initial Condition type only). This option is only available when Moving Wall is selected in the Wall dialog box and/or Frame Motion is selected in the Fluid dialog box.

User Source Terms

enables you to specify the additional source terms to the film continuity (Mass Flux), momentum (X-Momentum Flux, Y-Momentum Flux, and Z-Momentum Flux), energy (Heat Flux), and passive scalar equations (Scalar Flux). This option is only available with initial conditions.

Flow Momentum Coupling

When this option is selected, the liquid film and the gas flow will share the same velocity at the interface of the liquid-gas interface using a two-way coupling. When this option is not selected, the coupling between the liquid film and the gas flow is only one-way, namely, while the gas flow impacts the film flow, the film flow does not impact the bulk of the gas flow.

Film Phase Change

enables the phase change for the selected wall. This option is available only when Phase Change is selected in the Model Options and Setup tab of the Eulerian Wall Film Dialog Box. Once enabled, you can specify the following Phase Change Parameters (see Coupling of Wall Film with Mixture Species Transport in the Theory Guide):

Condensation Rate Constant

is the value of used in Equation 19–28 in the Theory Guide. You can also specify the condensation rate via a user-defined profile UDF by selecting the name of the compiled UDF from the drop-down list.

Vaporization Rate Constant

is the value of used in Equation 19–28 in the Theory Guide. You can also specify the vaporization rate via a user-defined profile UDF by selecting the name of the compiled UDF from the drop-down list.

Impingement Parameters

contains parameters related to particle-wall impingement

Impingement Model

is a drop-down list that contains available impingement models:

DPM Wall Splash

allows you to enable the wall splashing for the selected wall and specify the Number of Splashed Particles. The minimum value is 3. This option is available when Particle Splashing is enabled in the Eulerian Wall Film dialog box.

Kuhnke Model Parameters

(available when the kuhnke model is selected from the Impingement Model drop-down list)

Wall Roughness Length

enables you to specify wall roughness values used by the Kuhnke model:

Critical Temperature Factor

is the dimensionless variable that is used to determine the impingement regime transition temperature in Equation 16–254 in the Fluent Theory Guide.

Potential

displays the boundary conditions for the electric potential field at the wall. This tab is available only if you have enabled either the Electric Potential model under the Model tree branch or the Electrochemical Reaction model in the Species Dialog Box.

Electrochemical Reaction

enables electrochemical reactions at the wall. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.

Faradaic Heat

(if enabled) includes heat from the electrochemical reaction in the energy equation. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.

Reaction Mechanism

contains a drop-down list of all available electrochemical reaction mechanisms. This option is available only if Electrochemical reactions are enabled in the Species Model dialog box.

Potential Boundary Condition

contains a drop-down list of available potential boundary condition types for the external wall. You will need to specify one of the following:

  • Current Density (Select the Specified Flux potential boundary condition)

  • Potential at the wall (Select the Specified Value potential boundary condition)

This control is available only for one-sided external walls. For two-sided internal walls, the solver always uses the coupled treatment.

Contact Resistance

is the contact resistance at the wall, in Equation 20–3 in the Fluent Theory Guide. For two-sided internal walls, you only need to define the contact resistance at one of the walls. The value you specify will be automatically copied to the other side of the wall.


Release 18.2 - © ANSYS, Inc. All rights reserved.