ANSYS Fluent provides various options for modeling heat exchangers, each with their own features and limitations. The following instructions can help you determine which option/combination of options is the most appropriate for your problem.
Decide whether you want to use the dual cell model or the macro model.
The dual cell model provides the greatest flexibility with regard to the shape of the heat exchanger core and the nature of the mesh, and allows the auxiliary fluid to be highly non-uniform as it enters the core (for example, due to passing through arbitrary shaped inlet tanks). However, the dual cell model may need to be discounted as an option because of the following limitations:
If the heat exchanger performance data that you have is in the form of a velocity vs. effectiveness curve, the dual cell model cannot be used.
The dual cell model does not allow you to model phase change in the auxiliary fluid.
If the previous limitations are not relevant for your problem, you can proceed directly to using the dual cell model, as described in Using the Dual Cell Heat Exchanger Model.
While the macro model has more restrictions than the dual cell model, it is quite suitable for a thin 3D heat exchanger core with a rectangular cross-section, where the pass-to-pass plane is perpendicular to the primary flow direction, the auxiliary flow is uniform (so it can be treated as a 1D flow), and the mesh is uniform and structured. To verify that your problem can tolerate the limitations of the macro model, see Restrictions.
If you chose to use the macro model in the previous step, you must decide whether you want to use the grouped or ungrouped version of this model. If you want to define a single heat exchanger using multiple fluid zones, or if you would like to connect the fluid flow path among multiple heat exchangers, you should use the grouped version, as described in Using the Grouped Macro Heat Exchanger Model. Otherwise, you can use the ungrouped version, as described in Using the Ungrouped Macro Heat Exchanger Model.
If you chose to use the macro model in the step 1., you must decide whether you want to model the heat transfer using the number-of-transfer-units (NTU) method or the simple effectiveness method. This decision largely rests on the kind of experimental data that you have: the NTU method requires that you provide the various primary fluid flow rates and auxiliary fluid flow rates and the corresponding heat transfer values; the simple effectiveness method requires that you provide the data points for a curve that defines how the effectiveness (that is, the ratio of actual rate of heat transfer between the primary and auxiliary fluids to the maximum possible rate of heat transfer) varies with the fluid velocity. Additionally, you should consider the differences between the two heat transfer models outlined in Table 13.1: NTU Model Vs. Simple Effectiveness Model.
Table 13.1: NTU Model Vs. Simple Effectiveness Model
| NTU Model | Simple Effectiveness Model | |
|---|---|---|
| How many phases are allowed in the auxiliary flow? | single phase only | single phase and two phase |
| Can you model primary fluid-side reverse flow? | Yes | No |
| Can the primary fluid have a variable density? | Yes | No |
| Must the primary fluid heat capacity be less than the auxiliary fluid heat capacity? | No | Yes |
You will specify whether you want the NTU or simple effectiveness model in the Model Data tab of either the Ungrouped Macro Heat Exchanger dialog box or the Heat Exchanger Group dialog box, depending on whether you opted for the ungrouped or grouped version of the macro model, respectively.
An overview of the options available to you when modeling heat exchangers is shown in Figure 13.2: Heat Exchanger Modeling Options.