You can import the meshes from 3D CFX files, such
as definition (.def) and result (.res) files into ANSYS Fluent, using the File/Import/CFX ribbon tab item, as described in CFX Files. The fe2ram utility is used as the import filter, which can be used as a stand-alone
program to obtain an ANSYS Fluent mesh file. See Using the fe2ram Filter to Convert Files for information about fe2ram.
Important: Note that you have the ability to import only the mesh from a CFX file, and not any results or data.
When importing a mesh from a CFX definition or results file, select whether you want the ANSYS Fluent zones to be created from the physics data objects or the primitive mesh region objects. The former option is the default and is called “Zoning by CCL” and the latter option is called “Zoning by Group”. This will allow you to choose the type of mesh topology you would like to preserve when importing the file:
If you want zones to be created from the physics data objects, enable Create Zones from CCL Physics Data in the Select File dialog box.
If you want zones to be created from the primitive mesh region objects, disable Create Zones from CCL Physics Data in the Select File dialog box. This will result in the group zoning.
Important: The primitive mesh topology may contain additional regions that do not appear in the physics definition.
The default import method is the Create Zones from CCL Physics Data method. This method will not import CFX subdomain regions, however, the zoning by group method can import subdomain regions.
The 3D element set corresponding to zones/domains present in these files are imported as cell zones in ANSYS Fluent. They may contain tetrahedral, pyramidal, wedge, and hexahedral elements. The boundary zones in these files are a group of faces with a boundary condition name/type and are imported as face zones with the boundary condition name/type retained in ANSYS Fluent. The following boundary condition types are retained:
inlet
outlet
symmetry
interface
wall
The boundaries of type Interface may
be conformal or non-conformal. If they are non-conformal, they are
retained. However, conformal interfaces contain coincident nodes that
are merged and changed to type Interior.
For some cases, for the merge to work correctly, the merge tolerance
may need to be adjusted. Alternatively, the Fuse Face Zones Dialog Box in ANSYS Fluent can be used to
merge the conformal interfaces. For details, see Fusing Face Zones.