10.6.6. Implicit Update Settings

For transient problems, you can enable implicit mesh updating when you want to have the dynamic mesh updated during a time step (as opposed to just at the beginning of a time step). This capability is beneficial only for applications in which the mesh motion depends on the flow field (for example, cases that use the six DOF solver or involve fluid-structure interaction). For such applications, having the mesh motion updated within the time step based on the converging flow solution results in a stronger coupling between the flow solution and the mesh motion, and leads to a more robust solver run. Implicit mesh updating allows you to run simulations that otherwise could not be solved or would require an unreasonably small time step.

Note that implicit mesh updating cannot be used with the following:

To enable implicit mesh updating, perform the following steps:

  1. Enable Implicit Update in the Options group box of the Dynamic Mesh Task Page (Figure 10.13: The Dynamic Mesh Task Page).

  2. Click the Settings... button to open the Options Dialog Box.

    Figure 10.72:  The Implicit Update Tab of the Options Dialog Box

    The Implicit Update Tab of the Options Dialog Box

    Click the Implicit Update tab and enter values for the settings.

    1. Enter a value for Update Interval, in order to specify the frequency in iterations at which the mesh will be updated within a time step.

    2. Enter a value (within the range of 0 to 1) for Motion Relaxation, in order to define the relaxation of the motion (that is, displacement of the nodes) during the mesh update. The relaxation of the displacements is defined by the following equation:

      (10–29)

      where is the node position at iteration (within a time step), is the computed node position (based on the flow field), and is the motion relaxation.

    3. Enter a value for Residual Criteria, in order to set the relative residual threshold that is used to check the motion convergence. The residual criteria is applied to a relative residual. ANSYS Fluent scales the difference between the motion in iteration and iteration by the motion computed at the beginning of the time step. If this relative motion difference is smaller than the residual criteria, the mesh motion is considered converged.

  3. If you are using a UDF to compute the motion, make sure that the UDF uses the current flow field during each call to compute the motion (that is, no previously stored information should be used). This is necessary, as the UDF will be called each time the mesh is updated — which can be several times within a time step, depending on what you entered for the Update Interval.

  4. After you run the simulation, make sure that the motion (and consequently, the solution) is properly converged. If the motion requires more iterations to converge than the flow field, a warning will be displayed in the console during the iteration process. Note that the maximum number of iterations per time step (defined in the Run Calculation task page) is respected by the mesh motion convergence check.


Release 18.2 - © ANSYS, Inc. All rights reserved.