To export data to files that are compatible with ANSYS CFD-Post, select CFD-Post Compatible from the File Type drop-down list. Next, specify the Cell Zones that contain the data you want exported; note that by default, all of the cell zones will be exported. If you want to export solution data for particular surfaces, then select them from the Surfaces list. Once you have chosen your cells zones and/or surfaces you must select the Quantities that you want exported. When selecting the variables, be sure to include any variable that was used to create an isosurface or clipped surface (as described in Isosurfaces and Clipping Surfaces, respectively); otherwise, the surface will not be created properly if you try to read the exported state file in CFD-Post.
Specify the format of the .cdat file
by selecting either Binary or ASCII from the Format list. The advantage of the
binary format is that it takes less time to load the exported data
into ANSYS CFD-Post and requires less storage space. Note that the
format for the .cst will always be ASCII.
By default, Fluent will write a case file
(that is, .cas) along with the CFD-Post Compatible files. If you do not want such a case
file for any reason (for example., to improve I/O performance or save
disc space), disable the Write Case File option.
Disabling this option is only recommended if you are performing multiple
export operations for a case file that is not changing.
Click the button to save the
files, using the Select File dialog box. A .cdat file is written, containing the specified variable
data for the specified cell zones and all of the boundary zones. A
state file (that is, .cst) is also written,
which contains the following surfaces that you created in Fluent for
postprocessing: point surfaces, line surfaces, plane surfaces, isosurfaces,
and clipped surfaces (see Creating Surfaces and Cell Registers for Displaying and Reporting Data).
Note: Imprinted surfaces defined in ANSYS Fluent are not available for postprocessing in ANSYS CFD-Post.
Important: When you read the .cdat file into ANSYS CFD-Post,
the application will attempt to read in the case file that produced
the data by looking in the folder for a .cas file with the same prefix. If the case file is not in that folder
(e.g., if you disabled the Write Case File option
when exporting), ANSYS CFD-Post will prompt you to specify the appropriate
case file.
Important: Before loading the .cst file into ANSYS CFD-Post,
make sure that the .cas and .cdat files are already loaded for the session.
You have the option of exporting data at specified intervals during a transient calculation through the Automatic Export dialog box. See Exporting Data During a Transient Calculation for the complete details.