28.13.3. Solving Pseudo-Transient Flow

With the Pseudo Transient option enabled in the Solution Methods task page, you can now specify the time step for the Fluid Zone and/or the Solid Zone under Pseudo Transient Options in the Run Calculation task page (Figure 28.21: The Run Calculation Task Page for the User Specified Pseudo Transient Option).

 Solution →   Run Calculation

Figure 28.21:  The Run Calculation Task Page for the User Specified Pseudo Transient Option

The Run Calculation Task Page for the User Specified Pseudo Transient Option

  1. Select the Time Step Method for the Fluid Time Scale.

    1. If you choose User Specified, you will enter the Pseudo Time Step, which is used for every equation unless the equation specific time step is used for a particular equation, as mentioned in Setting Solution Controls for the Pseudo Transient Method.

    2. If you choose Automatic, which is the default method, (see Figure 28.22: The Run Calculation Task Page for the Automatic Pseudo Transient Option), the pseudo time step is calculated internally and used for each equation listed, unless the equation has a time step specified as noted in Setting Solution Controls for the Pseudo Transient Method. For more information about the automatic time step calculation, refer to Automatic Pseudo Transient Time Step in the Theory Guide.

      Select the Length Scale Method. Three options are available in the drop-down list:

      1. Conservative is the default length scale calculation method, for which you will enter the Timescale Factor. The Timescale Factor is a scaling factor used to scale the calculated time step. The default value is 1.0. You can increase or decrease it to increase or decrease the size of the time step, respectively.

      2. Aggressive predicts a higher time step size than the Conservative method. You will also need to specify the Timescale Factor.

      3. User Specified allows you to control the input for the Length Scale. This method is particularly useful in problems that have a specific length scale that is difficult to determine from the overall geometry of the problem. For example, in the case of flow over an airfoil, the appropriate length scale would be the length of the airfoil instead of the length scale calculated based on the geometry of the entire domain.

      4. You can specify the Verbosity. This is an integer value of 0 or 1. The default value is 0. If you want to print the pseudo time step size, enter a value of 1 for the Verbosity.

      Figure 28.22:  The Run Calculation Task Page for the Automatic Pseudo Transient Option

      The Run Calculation Task Page for the Automatic Pseudo Transient Option


  2. Select the Time Step Method for the Solid Time Scale.


    Note:   Solid Time Scale only appears in the interface when a solid zone is present in the domain or when the Energy equation is enabled along with Porous Zone or the Solidification & Melting model.


    1. If you choose User Specified, you will enter the Pseudo Time Step, which is used where the Solid Time Scale is needed (that is, solid zones, porous zones, and/or solidification/melting model).

    2. If you choose Automatic, which is the default method, the pseudo time step is calculated internally as described in Automatic Pseudo Transient Time Step in the Theory Guide. Specify a Timescale Factor to control/adjust the pseudo time step obtained from the automatically calculated Solid Time Scale.

  3. Continue setting up your solution as you would a steady-state run, as described in Performing Steady-State Calculations.


Release 18.2 - © ANSYS, Inc. All rights reserved.