The diesel unsteady laminar flamelet model can only be enabled when conditions for compression-ignition are met:
The Transient solver is selected in the General task page (or in the tree from the Setup/General/ Analysis Type).
The In-Cylinder dynamic mesh is enabled.
The Discrete Phase model option Interaction with Continuous Phase is selected.
The basic steps for setting the diesel unsteady laminar flamelet models are as follows.
In the Chemistry tab, select Diesel Unsteady Flamelet.
If a detailed chemical mechanism containing kinetic reactions appropriate for compression ignition has not yet been defined in your case, you can import a mechanism in CHEMKIN format as described in Importing a Volumetric Kinetic Mechanism in CHEMKIN Format.
The mechanism can include pollutant formation reactions as well if you are interested in modeling emissions.
In the Boundary tab, define the stream compositions as described in Defining the Stream Compositions.
In the Flamelet tab, set the following flamelet parameters.
Set the Number of Grid Points in Flamelet.
Set the Number of Unsteady Flamelets that ANSYS Fluent will generate during simulation.
(for multiple unsteady flamelets) Set the flamelet start times.
ANSYS Fluent automatically sets the start time for the first flamelet, but you must set the start time for each consecutive flamelet using the Unsteady Flamelet Parameters dialog box. Open it by clicking Set Flamelet Parameters and enter the start time for each flamelet either in seconds or in crank angles if the dynamic mesh is enabled.
ANSYS Fluent starts simulation with only one flamelet, and then it automatically introduces new flamelets into the reacting domain at the times you have specified.
The default initial condition for an unsteady flamelet is unburnt. ANSYS Fluent provides the Burnt Initial Flamelet option that allows you to set the initial flamelet condition to a chemical equilibrium burnt state. This option is useful if you are modeling internal combustion engines where residual gases may be present in the cylinder before the spray is injected, which would be incorrectly modeled by the unburnt state. Note that the Burnt Initial Flamelet is only used at case initialization.
(optional) Specify the flamelet fluid zones.
ANSYS Fluent calculates diesel unsteady flamelets using the zone-averaged pressure and scalar dissipation at every time step. By default, the averaging is performed over all fluid zones in the domain, but you can also select and/or deselect the fluid zones using the Flamelet Fluid Zones dialog box. Open this dialog box by clicking Set Flamelet Fluid Zones and select the fluid zones to be used for calculating average pressure and scalar dissipation. If no fluid zone is selected, ANSYS Fluent will compute domain average pressure and scalar dissipation using all fluid zones.
Note: For internal combustion cases, it is recommended that you select the cylinder fluid zones and deselect the intake and exhaust fluid zones.
Note that ANSYS Fluent calculates flamelets at every time step of the run. For this reason, the option to calculate the flamelets as a preprocessing step before running your simulation is unavailable, and Calculate Flamelets appears dimmed.
In the Table tab, set the PDF table parameters as described in Calculating the Look-Up Tables.
Note that ANSYS Fluent calculates PDF table at every time step of the run. For this reason, the option to calculate the PDF table as a preprocessing step before running your simulation is unavailable, and Calculate PDF Table appears dimmed.
When setting up and using the Diesel Unsteady Flamelet model for internal combustion engine simulations, the following recommendations apply:
Number of Flamelets
You must specify at least two diesel unsteady flamelets. ANSYS Fluent will use the first flamelet to model trapped burnt gases from the previous cycle. The second flamelet will start at the crank angle (CA) of fuel injection, specified in the Unsteady Flamelet Parameters dialog box (see Figure 15.10: The Flamelet Fluid Zones Dialog Box).
To model split injections where an initial fuel mass is injected and burns before the main fuel injection, three or more unsteady flamelets are required.
Flamelet Initialization
By default, the flamelet is initialized as mixed-but-unburnt. However, in all practical scenarios there is always some trapped gas remaining inside the cylinder. Therefore, it is recommended that you use the Burnt Initial Flamelet option in the Unsteady Flamelet Parameters dialog box (see Figure 15.10: The Flamelet Fluid Zones Dialog Box). When this option is selected, ANSYS Fluent performs a constant temperature equilibrium calculation and sets the initial flamelet condition to a chemical equilibrium burnt state.
Multi-cycle simulations
To accurately model multiple cycles of internal combustion engines, the flamelets must be reset at the end of each cycle. This is performed by defining the Diesel Unsteady Flamelet Reset event, typically at the specified crank angle, just before the inlet valve opens. Refer to the Resetting Diesel Unsteady Flamelets for details. This approach is recommended for modeling the EGR trapped gases with the first burnt unsteady flamelet.
If you are using the Inert (EGR) model in order to track the trapped inert mixture, you need to define the Inert EGR Reset event at the specified crank angle just before the inlet valve opens. See Resetting Inert EGR for details.