Discrete phase boundary conditions can be set for boundaries in the dialog boxes opened from the Boundary Conditions task page. When one or more injections have been defined, inputs for the discrete phase will appear in the dialog boxes. In the Walls dialog boxes, you will need to click the DPM tab to access the Discrete Phase Model Conditions as shown in Figure 23.24: Discrete Phase Boundary Conditions in the Wall Dialog Box.
The available boundary conditions are:
reflect
The particle rebounds off the boundary with a change in its momentum. ANSYS Fluent provides two models for computing this change:
For non-rotating particles, the momentum depends on the coefficient of restitution (Equation 16–212 in the Fluent Theory Guide).
For rotating particles, the model proposed by Tsuji et al. 492 is used. The particle rotation model includes frictional effects.
The details on these two models can be found in Wall-Particle Reflection Model Theory in the Fluent Theory Guide.
For information on how to set up the parameters for non-rotating and rotating particle models, see Coefficients of Restitution and Friction Coefficient, respectively.
When at least one injection accounts for the rough wall model (the Rough Wall Model option is selected under the Physical Models tab in the Set Injections Properties dialog box), you can specify the wall surface roughness parameters as described in Rough Wall Model.
trap
The trajectory calculations are terminated and the fate of the particle is recorded as “trapped”. In the case of evaporating droplets, their entire mass instantaneously passes into the vapor phase and enters the cell adjacent to the boundary. See Figure 23.25: “Trap” Boundary Condition for the Discrete Phase. In the case of combusting particles, the remaining volatile mass is passed into the vapor phase.
escape
The particle is reported as having “escaped” when it encounters the boundary in question. Trajectory calculations are terminated. See Figure 23.26: “Escape” Boundary Condition for the Discrete Phase.
wall-jet
The wall-jet type boundary condition is appropriate for high-temperature
walls where no significant liquid film is formed, and in high-Weber-number
impacts where the spray acts as a jet. The model is not appropriate
for regimes where film is important (for example, port fuel injection
in SI engines, rainwater runoff, and so on).
A more detailed description of underlying theory is available in Wall-Jet Model Theory in the Theory Guide.
wall-film
This boundary condition offers the following two impingement models:
stanton-rutland: (default) consists of four
regimes, namely, stick, rebound, spread, and splash, which are based
on the impact energy and wall temperature. See The Stanton-Rutland Model in the Fluent Theory Guide for more details.
kuhnke: consists of four regimes spread, rebound, splash, and dry splash
(thermal breakup). See The Kuhnke Model in the Fluent Theory Guide for more details.
For the kuhnke model, you must specify the following DPM Wall Roughness Parameters:
Roughness
Ra: is used to compute in Equation 16–262 in the Fluent Theory Guide.
Roughness Rz: is used to compute splashed droplets ejection angle in Equation 16–274 in the Fluent Theory Guide.
If you want to model splashing, you can specify Number of Splash Drops. A value of zero implies that the splashing model will not be used.
The Critical Temperature
Factor is used to determine the transition temperature
(Equation 16–226 and Equation 16–254 in the Fluent Theory Guide for
the stanton-rutland and kuhnke splashing models, respectively).
Detailed information on the wall film model can be found in Wall-Film Model Theory in the Fluent Theory Guide.
For a list of limitations that exist with wall-film boundary conditions, see Limitations on Using the Lagrangian Wall Film Model.
interior
This boundary condition means that the particles will pass through the internal boundary. This option is available only for internal boundary zones, such as a radiator or a porous jump.
It is also possible to use a user-defined function to compute the behavior of the particles at a physical boundary. More information about user-defined functions can be found in the Fluent Customization Manual.
Because you can stipulate any of these conditions at flow boundaries, it is possible to incorporate mixed discrete phase boundary conditions in your ANSYS Fluent model.