Instructions for specifying the necessary information for the primary and secondary phases and their interaction for a mixture model calculation are provided below.
The procedure for defining the primary phase in a mixture model calculation is the same as for a VOF calculation. See Defining the Primary Phase for details.
To define a non-granular (that is, liquid or vapor) secondary phase in a mixture multiphase calculation, perform the following steps:
Select the phase (for example, phase-2) in the Phases list.
Click to open the Secondary Phase Dialog Box (Figure 24.33: The Secondary Phase Dialog Box for the Mixture Model).
In the Secondary Phase dialog box, enter a Name for the phase.
Specify which material the phase contains by choosing the appropriate material in the Phase Material drop-down list.
Define the material properties for the Phase Material, following the same procedure you used to set the material properties for the primary phase (see Defining the Primary Phase). For a particulate phase (which must be placed in the fluid materials category, as mentioned in Steps for Using a Multiphase Model), you need to specify only the density; you can ignore the values for the other properties, since they will not be used.
In the Secondary Phase dialog
box, specify the Diameter of the bubbles, droplets,
or particles of this phase ( in Equation 17–129 in the Theory Guide). You can
specify a constant value, or use a user-defined function. See the Fluent Customization Manual for details about
user-defined functions. Note that when you are using the mixture model
without slip velocity, this input is not necessary, and it will not
be available to you.
Click in the Secondary Phase dialog box.
To define a granular (that is, particulate) secondary phase in a mixture model multiphase calculation, perform the following steps:
Select the phase (for example, phase-2) in the Phases list.
Click to open the Secondary Phase Dialog Box (Figure 24.34: The Secondary Phase Dialog Box for a Granular Phase Using the Mixture Model).
In the Secondary Phase dialog box, enter a Name for the phase.
Specify which material the phase contains by choosing the appropriate material in the Phase Material drop-down list.
Define the material properties for the Phase Material, following the same procedure you used to set the material properties for the primary phase (see Defining the Primary Phase). For a granular phase (which must be placed in the fluid materials category, as mentioned in Steps for Using a Multiphase Model), you need to specify only the density; you can ignore the values for the other properties, since they will not be used.
Important: Note that all properties for granular flows can be defined by user-defined functions (UDFs).
See the Fluent Customization Manual for details about user-defined functions.
Enable the Granular option.
In the Secondary Phase dialog box, specify the following properties of the particles of this phase:
specifies the diameter of the particles. You can select constant in the drop-down list and specify a constant value, or select user-defined to use a user-defined function. See the Fluent Customization Manual for details about user-defined functions.
specifies the method for computing the kinetic () and collisional (
) components of the granular viscosity (Equation 17–137 in the Fluent Theory Guide). Selecting constant, syamlal-obrien (Equation 17–139 in the Fluent Theory Guide), or gidaspow (Equation 17–140 in the Fluent Theory Guide) will use these expressions for
the kinetic portion of the viscosity and will calculate the collisional
portion of the viscosity from Equation 17–138 in the Fluent Theory Guide. Alternatively,
you can select user-defined to use a user-defined
function. Note that if you select user-defined, your user-defined function must include both the kinetic portion
and the collisional portion of the viscosity in the value it returns.
specifies the pressure gradient term, ,
in the granular-phase momentum equation. Choose none to exclude frictional pressure from your calculation, johnson-et-al to apply Equation 17–316 in the Theory Guide, syamlal-obrien to apply Equation 17–228 in the Theory Guide, based-ktgf, where the frictional pressure is defined by
the kinetic theory [26]. The solids pressure
tends to a large value near the packing limit, depending on the model
selected for the radial distribution function. You must hook a user-defined
function when selecting the user-defined option.
See the Fluent Customization Manual for
information on hooking a UDF.
is defined as
(24–9) |
with , which is the derived option. You can also specify a user-defined function for the frictional modulus.
specifies a threshold volume fraction at which the frictional regime becomes dominant. It is assumed that for a maximum packing limit of 0.6, the frictional regime starts at a volume fraction of about 0.5. This is only a general rule of thumb as there may be other factors involved. The default value is 0.61.
specifies temperature for the solids phase and is proportional to the kinetic energy of the random motion of the particles. Choose either the algebraic, the constant, or user-defined option.
specifies the pressure gradient term, , in the granular-phase momentum equation.
Choose either the lun-et-al, the syamlal-obrien, the ma-ahmadi, or the user-defined option.
specifies a correction factor that modifies the probability of collisions between grains when the solid granular phase becomes dense. Choose either the lun-et-al, the syamlal-obrien, the ma-ahmadi, the arastoopour, or a user-defined option.
is defined as
(24–10) |
with .
Choose either the derived or user-defined options.
specifies the maximum volume fraction for the granular phase. For monodispersed spheres, the packing limit is about 0.63, which is the default value in ANSYS Fluent. In polydispersed cases, however, smaller spheres can fill the small gaps between larger spheres, so you may need to increase the maximum packing limit.
Click in the Secondary Phase dialog box.
To solve the transport equation for interfacial area concentration of the secondary phase in the mixture model (Interfacial Area Concentration in the Fluent Theory Guide, perform the following steps:
Select the phase (for example, phase-2) in the Phases list.
Click to open the Secondary Phase Dialog Box (Figure 24.35: The Secondary Phase Dialog Box Displaying the Interfacial Area Concentration Settings).
In the Secondary Phase dialog box, enter a Name for the phase.
Specify which material the phase contains by choosing the appropriate material in the Phase Material drop-down list.
Define the material properties for the Phase Material.
Enable the Interfacial Area Concentration option. Make sure the Granular option is disabled for the Interfacial Area Concentration option to be visible in the interface.
In the Secondary Phase dialog box, specify the following properties of the particles of this phase:
specifies the diameter of the particles or bubbles. You can select constant in the drop-down list and specify a constant value, or select user-defined to use a user-defined function. See the Fluent Customization Manual for details about user-defined functions. The Diameter recommended setting is sauter-mean, allowing for the effects of the interfacial area concentration values to be considered for mass, momentum and heat transfer across the interface between phases.
specifies the surface tension at the liquid-air interface. You can select either the hibiki-ishii or the ishii-kim model.
allows you to specify the coalescence and breakage kernels. You can select none, constant, hibiki-ishii, ishii-kim, yao-morel, or user-defined. The three options, hibiki-ishii, ishii-kim and yao-morel are described in detail in Interfacial Area Concentration in the Theory Guide.
In addition to specifying the hibiki-ishii, ishii-kim, and yao-morel as the coalescence
and breakage kernels, you can also tune the properties of the three
models by using the /define/phases/iac-expert/hibiki-ishii-model, /define/phases/iac-expert/ishii-kim-model, and /define/phases/iac-expert/yao-morel-model text commands.
For each of the three models you can specify the parameters listed in Table 24.12: Parameters for the Coalescence and Breakage Kernels
Table 24.12: Parameters for the Coalescence and Breakage Kernels
| Hibiki-Ishii Model | Ishii-Kim Model | Yao-Morel Model |
|---|---|---|
Coefficient Gamma_c
|
Coefficient Crc
|
Coefficient K_c1
|
Coefficient K_c
|
Coefficient
Cwe
|
Coefficient K_c3
|
Coefficient Gamma_b
|
Coefficient C
|
Coefficient K_b1
|
Coefficient K_b
|
Coefficient Cti
|
alpha_max
|
alpha_max
|
alpha_max
|
These values are discussed in greater detail in Interfacial Area Concentration in the Theory Guide.
is a source term for the interfacial area concentration that models the rate of formation of the dispersed phase. You can choose from constant or user-defined.
will need to be specified if you selected ishii-kim or yao-morel for the Breakage Kernel.
gives you the option to choose the formula which calculates the dissipation rate used in the hibiki-ishii and ishii-kim models. You can choose amongst constant, wu-ishii-kim, fluent-ke, and user-defined for the dissipation function.
The wu-ishii-kim option uses a simple algebraic correlation for :
(24–11) |
where
and
where ,
,
, and
are the mixture
density, mixture velocity, mixture molecular viscosity, and hydraulic
diameter of the flow path.
When you select the wu-ishii-kim model, you will set an additional input for Hydraulic Diameter.
is the value used in Equation 24–11, should you use the wu-ishii-kim formulation.
are the limits of the bubble diameters.
Note: When solving a steady-state problem, the preferred setting for the Under-Relaxation Factor is 1.0, as the interfacial area equation for the boiling models is currently under-relaxed using a locally defined pseudo-time step. If you want extra explicit under-relaxation, you may set the value of the Under-Relaxation Factor to less than one, this may be done only in case of serious convergence problems with the interfacial area transport equation. To improve convergence you can switch to a pseudo-time step for the interfacial area concentration only, using the define/phases/iac-expert/iac-pseudo-time-step text command and set the local pseudo-time to less than 1.
For mixture multiphase flows with slip velocity, you can specify the drag function to be used in the calculation. The functions available here are a subset of those discussed in Defining the Phases for the Eulerian Model. See Relative (Slip) Velocity and the Drift Velocity in the Theory Guide for more information.
To specify drag laws, click to open the Phase Interaction Dialog Box (Figure 24.36: The Phase Interaction Dialog Box for the Mixture Model (Drag Tab)), and then click the Drag tab.
If you are solving for slip velocities during the mixture calculation, and you want to modify the slip velocity definition, click to open the Phase Interaction Dialog Box (Figure 24.37: The Phase Interaction Dialog Box for the Mixture Model (Slip Tab)), and then click the Slip tab.
Under Slip Velocity, you can specify the slip velocity function for each secondary phase with respect to the primary phase by choosing the appropriate item in the adjacent drop-down list.
Select maninnen-et-al (the default) to use the algebraic slip method of Manninen et al. [65], described in Relative (Slip) Velocity and the Drift Velocity in the Theory Guide.
Select none if the secondary phase has the same velocity as the primary phase (that is, no slip velocity).
Select user-defined to use a user-defined function for the slip velocity. See the Fluent Customization Manual for details.