10.6. Using Dynamic Meshes

The steps for setting up a dynamic mesh problem are listed below. (Note that this procedure includes only those steps necessary for the dynamic mesh model itself; you must set up other models, cell zone conditions, boundary conditions, and so on, as usual.)

  1. Enable the appropriate option for modeling transient or steady flow in the General Task Page.

     Setup →   General

    If your problem involves a steady flow, see Steady-State Dynamic Mesh Applications for important considerations.

  2. Set cell zone conditions and boundary conditions as required in the Cell Zone Conditions Task Page and Boundary Conditions Task Page.

     Setup →   Cell Zone Conditions

     Setup →   Boundary Conditions

    See Cell Zone and Boundary Conditions for information about inputting conditions. The correct wall velocity is set up automatically when a dynamic zone is created for a wall zone and the motion attributes are specified, so you will not specify wall motion in the Wall dialog box. If you create a moving dynamic cell zone, then all wall boundaries adjacent to that cell zone will, by default, impose the correct (moving) boundary conditions, and it is not necessary to declare these wall zones as dynamic zones. Note that if a wall boundary mesh is moving because it belongs to an adjacent moving dynamic cell zone, but the physical boundary conditions are such that the wall is actually not moving, then you will have to declare this boundary as a dynamic zone and specify that the mesh motion is not included in the boundary conditions (see Specifying the Motion of Dynamic Zones).

  3. Enable the dynamic mesh model, and specify related parameters in the Dynamic Mesh Task Page.

     Setup →   Dynamic Mesh →   Dynamic Mesh

    See Setting Dynamic Mesh Modeling Parameters for details.

  4. Create the dynamic zones for your model, using the Dynamic Mesh Zones Dialog Box.

     Setup →   Dynamic Mesh → Create/Edit...

    See Specifying the Motion of Dynamic Zones for details.

  5. You can display the motion of the moving zones with prescribed motion to verify the simulation setup.

     Setup →   Dynamic Mesh → Display Zone Motion...

    See Previewing the Dynamic Mesh for details.

  6. If it is a transient simulation, define the events that will occur during the calculation.

     Setup →   Dynamic Mesh → Events...

    See Defining Dynamic Mesh Events for details.

  7. Save the case and data.

     File → Write → Case & Data...

  8. Preview your dynamic mesh setup (when the motion is a prescribed motion). See Steady-State Dynamic Mesh Applications for previewing your steady-state dynamic mesh motion and refer to Previewing the Dynamic Mesh for details.

     Setup →   Dynamic Mesh → Preview Mesh Motion...

  9. Specify the pressure-velocity coupling scheme. For transient flow calculations, the PISO algorithm is recommended, as it is the most efficient for such cases (see PISO for details).

  10. Use the automatic saving feature to specify the file name and frequency with which case and data files should be saved during the solution process.

     Solution → Calculation Activities → Autosave (Every) → Edit...

    See Automatic Saving of Case and Data Files for details about the use of this feature. This provides a convenient way for you to save results at successive time steps for later postprocessing.


    Important:  You must save a case file each time you save a data file because the mesh position is stored in the case file. Since the mesh position changes with each time step, reading data for a given time step will require the case file at that time step so that the mesh will be in the proper position. You should also save your initial case file so that you can easily return to the mesh’s original position to restart the solution if desired.


  11. (optional) If you want to create a graphical animation of the mesh over time during the solution procedure, you can use the Calculation Activities Task Page to set up the graphical displays that you want to use in the animation. See Animating the Solution for details.

For additional information, see the following sections:


Release 18.2 - © ANSYS, Inc. All rights reserved.