For information about postprocessing heat transfer quantities, see the following sections:
ANSYS Fluent provides reporting options for simulations involving heat transfer. You can generate graphical plots or reports of the following variables/functions:
Static Temperature
Total Temperature
Enthalpy
Relative Total Temperature
Rothalpy
Wall Temperature
Wall Temperature (Thin)
Total Enthalpy
Total Enthalpy Deviation
Entropy
Total Energy
Internal Energy
Total Surface Heat Flux
Surface Heat Transfer Coef.
Surface Nusselt Number
Surface Stanton Number
The first 12 variables listed above are contained in the Temperature... category of the variable selection drop-down list that appears in postprocessing dialog boxes, and the remaining variables are in the Wall Fluxes... category. See Field Function Definitions for their definitions.
The reported enthalpy values may be different between the pressure-based and density-based solver depending on the properties of the working fluid, compressible, incompressible, ideal gas, etc. For details, see the discussion of enthalpy in The Energy Equation in chapter 5, Heat Transfer of the Theory Guide.
You can use the Flux Reports dialog box to compute the heat transfer through each boundary of the domain, or to sum the heat transfer through all boundaries to check the heat balance.
Results → Reports
→ Fluxes
Edit...
It is recommended that you perform a heat balance check to ensure that your solution is truly converged.
Note: For the Composition PDF Transport model, the Flux Reports dialog box reports the Total Heat Transfer Rate and Total Sensible Heat Transfer Rate only for the Lagrangian phase solution, which does not always guarantee overall mass conservation due to the nature of the discrete phase model. To check the balance of heat transfer rates that are based on the continuous phase computation, you should use the Surface Integrals dialog box to create a report for the Flow Rate of Enthalpy (Temperature category). (See Reporting Heat Transfer Through a Surface for details.)
You can use the Surface Integrals dialog box to compute the heat transfer through any boundary or any surface created using the methods described in Creating Surfaces and Cell Registers for Displaying and Reporting Data.
Results → Reports
→ Surface Integrals
Edit...
To report the mass flow rate of enthalpy
(12–2) |
choose Flow Rate for the Report Type in the Surface Integrals dialog box, select Enthalpy (in the Temperature... category) as the Field Variable, and select the surface(s) on which to integrate.
The Surface Integrals dialog box can also be used to
generate a report of averaged heat transfer coefficient on a surface (
).
Results → Reports
→ Surface Integrals
Edit...
In the Surface Integrals dialog box, choose Area-Weighted Average for Report Type, select Surface Heat Transfer Coef. (in the Wall Fluxes... category) as the Field Variable, and select the surface.
It is possible to export heat flux data on wall zones (including radiation) to
a generic file that you can examine or use in an external program. To save a
heat flux file, you will use the custom-heat-flux text
command.
file → export
→ custom-heat-flux
Heat transfer data will be exported in the following free format for each face zone that you select for export:
zone-name nfaces x_f y_f z_f A Q T_w T_c HTC . . .
Each block of data starts with the name of the face zone
(zone-name) and the number of faces in the zone
(nfaces). Next there is a line for each face (that
is, nfaces lines), each containing the components of
the face centroid (x_f, y_f,
and, in 3D, z_f), the face area
(A), the heat transfer rate
(Q), the face temperature
(T_w), the adjacent cell temperature
(T_c), and the heat transfer coefficient
(HTC). If the heat transfer coefficient is
calculated based on wall function (Equation 33–55),
then is the convective heat transfer rate. Otherwise,
will be the total heat transfer rate, including radiation heat
transfer.