To import meshes in CFD general notation system (CGNS) format
(.cgns) into ANSYS Fluent, use the File/Import/CGNS/Mesh... ribbon tab item.
File → Import → CGNS → Mesh...
To import a mesh and the corresponding CGNS data, use the File/Import/CGNS/Mesh & Data... ribbon tab item.
File → Import → CGNS → Mesh &
Data...
To import only the CGNS data, use the File/Import/CGNS/Data... ribbon tab item.
File → Import → CGNS → Data...
Table 3.3: CGNS Variables Supported by ANSYS Fluent
| CGNS Variable Name | ANSYS Fluent Name |
|---|---|
| Pressure | pressure |
| ReynoldsStressXX | uu-stress |
| ReynoldsStressXY | uv-stress |
| ReynoldsStressXZ | uw-stress |
| ReynoldsStressYY | vv-stress |
| ReynoldsStressYZ | vw-stress |
| ReynoldsStressZZ | ww-stress |
| Temperature | temperature |
| TurbulentDissipation | epsilon |
| TurbulentDissipationRate | omega |
| TurbulentEnergyKinetic | k |
| VelocityX | x-velocity |
| VelocityY | y-velocity |
| VelocityZ | z-velocity |
To import data correctly, first import the mesh using the mesh only option (Mesh...) and set up the boundary conditions. For example, if a boundary zone is of type pressure-outlet and is read as outlet, it should be changed to pressure-outlet before importing the data. Then select the appropriate model and read the data using the data only option (Data...)
The new and original meshes should have the same zones, numbered in the same order. A warning is issued if they do not, because inconsistencies can create problems with the boundary conditions.
ANSYS Fluent defaults to the Laminar Viscous Model after reading a CGNS mesh. You must select the appropriate model before reading data since ANSYS Fluent selectively imports only those values from the CGNS file required for a given model. For example, if Epsilon is available in the CGNS file, the model must be changed to k-epsilon to ensure that ANSYS Fluent will import this quantity.