3.12.3. Meshes and Data in CGNS Format

To import meshes in CFD general notation system (CGNS) format (.cgns) into ANSYS Fluent, use the File/Import/CGNS/Mesh... ribbon tab item.

 File → Import → CGNS → Mesh...

To import a mesh and the corresponding CGNS data, use the File/Import/CGNS/Mesh & Data... ribbon tab item.

 File → Import → CGNS → Mesh & Data...

To import only the CGNS data, use the File/Import/CGNS/Data... ribbon tab item.

 File → Import → CGNS → Data...

Table 3.3:  CGNS Variables Supported by ANSYS Fluent

CGNS Variable NameANSYS Fluent Name
Pressure pressure
ReynoldsStressXX uu-stress
ReynoldsStressXY uv-stress
ReynoldsStressXZ uw-stress
ReynoldsStressYY vv-stress
ReynoldsStressYZ vw-stress
ReynoldsStressZZ ww-stress
Temperature temperature
TurbulentDissipation epsilon
TurbulentDissipationRate omega
TurbulentEnergyKinetic k
VelocityX x-velocity
VelocityY y-velocity
VelocityZ z-velocity


Important:
  • To import data correctly, first import the mesh using the mesh only option (Mesh...) and set up the boundary conditions. For example, if a boundary zone is of type pressure-outlet and is read as outlet, it should be changed to pressure-outlet before importing the data. Then select the appropriate model and read the data using the data only option (Data...)

  • The new and original meshes should have the same zones, numbered in the same order. A warning is issued if they do not, because inconsistencies can create problems with the boundary conditions.

  • ANSYS Fluent defaults to the Laminar Viscous Model after reading a CGNS mesh. You must select the appropriate model before reading data since ANSYS Fluent selectively imports only those values from the CGNS file required for a given model. For example, if Epsilon is available in the CGNS file, the model must be changed to k-epsilon to ensure that ANSYS Fluent will import this quantity.



Release 18.2 - © ANSYS, Inc. All rights reserved.