If you are using any of the multiphase models for a compressible flow, note the following:
ANSYS Fluent allows the modeling of:
Multiple compressible ideal gas phases and/or incompressible/compressible liquids at any inlet
A single real gas or real liquid at any inlet
Multiple real gases at a single inlet
Multiple compressible liquids using either the Fluent built-in compressible liquid density model based on the Tait law (see Compressible Liquid Density Method) or user-defined functions
For multiple compressible phases, the fundamental equations for compressible flow remain the same. However, boundary conditions are modified to account for changes in material properties due to compressible fluid mixtures.
In cases of a mixture of ideal and real gases, the phases must enter the domain through separate inlets.
When using the VOF model, stability is improved if the primary phase is the compressible ideal gas.
If you specify the total pressure at a boundary (for example, for a pressure inlet or intake fan), Fluent will use the specified value for temperature at that boundary as total temperature for the compressible phase, and as static temperature for the other phases (which are incompressible).
For each mass-flow inlet, you will need to specify mass flow or mass flux for each individual phase.
Important: Note that if you read a case file that was set up in a version of Fluent previous to 6.1, you will need to redefine the conditions at the mass-flow inlets. See Defining Multiphase Cell Zone and Boundary Conditions for more information on defining conditions for a mass-flow inlet in multiphase calculations.
Compressible flow simulations may have convergence difficulties due to explicit handling of source term accounting for density variation. These simulations could become extremely unstable in the presence of a large variation in pressure and temperature. In ANSYS Fluent, an enhanced numerical treatment that provides better stability at startup and during calculation of compressible flows is enabled by default. The treatment controls the rate of change of pressure and temperature between iterations and provides additional diagonal dominance to the matrix of equations.
Although disabling the enhanced numerical treatment is not recommended, you can temporarily turn it off to investigate unstable cases using the following text user interface command:
solve/set/multiphase-numerics/compressible-flow/enhanced-numerics
...
enhanced compressible flow numerics? [yes] no
See Compressible Flows for more information about compressible flows.
A more general formulation for compressible multiphase flows employs a mathematically rigorous treatment of compressible phases at an inlet boundary. Instead of treating the entering incompressible and compressible phases as a pseudo-mixture, this formulation calculates static temperature and pressure using an iterative method based on fundamental thermodynamic relations (such as the Maxwell relations). This approach involves evaluation of the property derivatives, which can be computed either numerically or through analytic expressions. You can enable this alternative treatment via the text command:
solve/set/multiphase-numerics/compressible-flow/alternate-bc-formulation alternate compressible bc formulation? [no]yuse analytical thermodynamic derivatives? [no]y