The settings that are available in the Solution Methods task page (see Figure 24.64: The Solution Methods Task Page Displaying The Pressure-Velocity Coupling Options) for solving the coupled system of equations arising in multiphase flows are:
Phase Coupled SIMPLE (Eulerian multiphase)
PISO (VOF and mixture)
SIMPLE (VOF and mixture)
SIMPLEC (VOF and mixture)
Coupled (all multiphase models)
Coupled with Volume Fractions (all multiphase models except drift-flux)
Solve N-Phase Volume Fraction Equations (mixture and Eulerian models)
The PISO, SIMPLE, and SIMPLEC schemes apply to the VOF and mixture models and are discussed in Pressure-Velocity Coupling in the Theory Guide.
The Phase Coupled SIMPLE (PC-SIMPLE) is an extension of the SIMPLE algorithm [80] to multiphase flows. The velocities are solved coupled by phases in a segregated fashion. Fluxes are reconstructed at the faces of the control volume and then a pressure correction equation is built based on total continuity. The coefficients of the pressure correction equations come from the coupled per phase momentum equations. This method has proven to be robust and it is the only method available for all previous versions of ANSYS Fluent.
The Coupled scheme (also known as Multiphase Coupled in previous ANSYS Fluent versions) solves all equations for phase velocity corrections and shared pressure correction simultaneously [34]. These methods incorporate the lift forces and the mass transfer terms implicitly into the general matrix. This method works very efficiently in steady-state situations, or for transient problems when larger time steps are required.
The Coupled with Volume Fractions option (also known as Full Multiphase Coupled in previous ANSYS Fluent versions) couples velocity corrections, shared pressure corrections, and the correction for volume fraction simultaneously. Theoretically, it should be more efficient, however it may have some drawbacks in robustness and CPU time usage. The robustness issue stems from the lack of control of the solution of the volume fraction equation. The continuity constraint (sum of all volume fractions equals 1, and individual values limited between zero and one) cannot be enforced exactly during inner solver iterations, and slight variations from the physical limits may lead to divergence. Research is ongoing in this area to improve the method. The method is advantageous for heterogeneous mass transfer when a low Courant number is given; it also works well in dilute situations.
The Volume Fraction Coupling Method aims to achieve a faster steady-state solution compared to the segregated method of solving equations. It may not be a suitable option for transient applications due to the significant overhead in CPU time compared to the segregated method, unless it is run with a larger time step size.
Note: The Coupled with Volume Fractions option is available in the interface after you have selected Coupled from the Scheme drop-down list for Pressure-Velocity Coupling. For steady-state cases, the Pseudo Transient option will be enabled automatically when you enable the Coupled with Volume Fractions option for the VOF and mixture models.
The coupled with volume fractions option has the following limitations:
It is not available when Slip Velocity is enabled for the Mixture multiphase model.
It is not supported when using the Singhal-Et-Al cavitation model.
It is not supported when the Explicit formulation for volume fraction is selected.
Recommended uses of the coupled with volume fractions option:
The Pseudo-transient solver is recommended for steady-state calculations.
It is recommended that you use lower under-relaxation factors for momentum for higher order schemes.
For marine applications, it is recommended that you use a low-order variant or hybrid treatment for the Rhie-chow face flux interpolation (see High-Order Rhie-Chow Face Flux Interpolation).
It is recommended that you use the expert text command
options solve/set/coupled-vof-expert for
better stability when using the VOF model (see solve/ in the Text Command List).
For a multiphase flow, the sum of the phase volume fractions must always equal 1. By default, Fluent enforces this constraint by solving the volume fraction equations for each of the secondary phases and then setting the volume fraction of the primary phase to the complement.
In certain cases, where poor convergence and/or mass imbalance are observed, enabling Solve N-Phase Volume Fraction Equations may improve solutions, although in practice the results obtained from using this option are case dependent. If selected, this option will solve all volume fraction equations, including both primary and secondary phases. The resulting phase volume fractions are then scaled in order to satisfy the requirement of summing to 1. This approach is more computationally expensive than the default approach and, in general, should not be necessary for the simulation.
Note: The Solve N-Phase Volume Fraction Equations option is not available for the Volume of Fluid model or Eulerian with Multi-Fluid VOF Model enabled.