Simulations of transient particles often require time dependent
injection conditions. Potentially most of the point properties may
change over time. One method to accomplish this is the use of an Initialization function as described in DEFINE_DPM_INJECTION_INIT in the Fluent Customization Manual.
An easier way is to use transient profiles containing one or more variables based on the time or crank angle that can be assigned to various point properties: (Total) Mass Flow Rate, X-, Y-, Z- Velocity, Velocity Magnitude, and Cone Angle depending on the injection type selected. See Point Properties for Single Injections to Point Properties for Effervescent Atomizer Injections for the description of the individual properties.
Before transient profile variables can be assigned to point
properties of injections, a profile file has to be read into ANSYS Fluent using
the File/Read/Profile... ribbon tab item. In the Select File dialog box a transient profile in tabular format
with extension .ttab has to be chosen. Alternatively,
you can read this file into ANSYS Fluent using the read-transient-table text command.
file → read-transient-table
The profile name should not exceed 63 characters. See Defining Transient Cell Zone and Boundary Conditions for the format description. The following example illustrates an injection within 3 intervals of 2.5 milliseconds injection time, where the second injection has an elevated velocity.
mv-profile 3 13 0 time mass-flow velocity 0 0 0.1 0.00999 0 0.1 0.01 0.001 0.1 0.0125 0.001 0.1 0.01251 0 0.1 0.01999 0 0.1 0.02 0.001 5 0.0225 0.001 5 0.02251 0 0.1 0.02999 0 0.1 0.03 0.001 0.1 0.0325 0.001 0.1 0.03251 0 0.1
For the setting of point properties go to the Point Properties tab in the Set Injection Properties dialog box.
When transient profiles are loaded, you can choose either a constant method (the default) or profile from the Method drop-down list. If you select profile, you also must choose a profile from the corresponding drop-down list that appears in the Value column. The variable angle or time from the file is used as an independent interpolation variable and cannot be chosen as a profile.
Important: All quantities in the profile file, including coordinate values, must be specified in SI units. Specifically, Mass Flow Rate must be specified in kg/s, Velocity in m/s, and Cone Angle in radians. ANSYS Fluent does not perform unit conversion when reading profile files.