17.2.1. Setup and Solution Procedure

  1. Read your mesh file into ANSYS Fluent and set up any other models you plan to use in conjunction with the partially premixed combustion model (turbulence, radiation, and so on).

  2. Enable the partially premixed combustion model.

    1. Turn on the Partially Premixed Combustion model in the Species Model dialog box.


      Note:  Make sure a turbulence model (other than the Spalart-Allmaras model) is selected before selecting a combustion model.


       Setup → Models → Species   Edit...

    2. If you select the C Equation as the Premixed Model, then you have the choice of selecting one of the following State Relation models in the Chemistry tab: Chemical Equilibrim, Steady Diffusion Flamelet, Unsteady Diffusion Flamelet (for steady-state simulations starting from a converged Steady Diffusion Flamelet solution), or Flamelet Generated Manifold.

    3. If you select the Extended Coherent Flame Model, then you can select Chemical Equilibrim, Steady Diffusion Flamelet, and Unsteady Diffusion Flamelet. You can modify the Extended Coherent Flamelet Model Constants in the Premix tab. See Modifying the Constants for the ECFM Flame Speed Closure for details.

    4. If you select the G Equation as the Premixed Model, then you have the choice of selecting one of the following State Relation models in the Chemistry tab: Chemical Equilibrim or Steady Diffusion Flamelet.

  3. In the Chemistry tab of the Species Model dialog box, select the appropriate State Relation based on the type of partially premixed model you want to simulate. In ANSYS Fluent, there are two types of partially premixed models, namely a thin-flamelet model (equilibrium and diffusion flamelet) and a finite-thickness flamelet model, which is a Flamelet Generated Manifold. You can refer to Non-Premixed Combustion in the Fluent Theory Guide to learn about diffusion flamelets or Partially Premixed Combustion Theory in the Fluent Theory Guide for FGMs. Also, you can refer to Overview in the Fluent Theory Guide for general information about the thin-flamelet and finite-thickness flamelet models.

  4. If you select Flamelet Generated Manifold, you will also need to define whether the FGM is calculated from a premixed or a diffusion flamelet, as well as the Turbulence-Chemistry Interaction in the Premix tab. The three options (Finite-Rate, Turbulent Flame Speed, and Finite-Rate/Turbulent Flame Speed) are discussed in FGM Turbulent Closure in the Fluent Theory Guide.


    Note:  The Finite-Rate/Turbulent Flame Speed option uses the minimum of finite-rate and turbulent flame speed as discussed in the FGM Turbulent Closure in the Fluent Theory Guide. In the mixing layer regions, the adjacent cells could have different rate determining steps, which causes spurious species generation like generation of a product species. This can be minimized by selecting only Turbulent Flame Speed option.


  5. In the Flamelet tab, you can modify the Flamelet Parameters as described in Flamelet Generated Manifold.

  6. Generate a PDF look-up table. The table parameters are defined in Calculating the Look-Up Tables.


    Important:  If ANSYS Fluent warns you during the partially premixed properties calculation that any parameters are out of the range for the laminar flame speed function, you will need to modify the piecewise-linear points manually before saving the PDF file. See Modifying the Unburnt Mixture Property Polynomials for details. Also, the calculation of the thermal diffusivity uses the thermal conductivity in the Create/Edit Materials dialog box. More accurate thermal diffusivity polynomials can be obtained by editing the thermal conductivity in the Create/Edit Materials dialog box and then clicking Recalculate Properties in the Properties tab.


  7. Define the physical properties for the unburnt material in the domain.

     Setup →   Materials

    ANSYS Fluent will automatically select the prepdf-polynomial function for Laminar Flame Speed, indicating that the piecewise-linear polynomial function from the PDF look-up table will be used to compute the laminar flame speed. You may also choose to enter a constant value, use a user-defined function, metghalchi-keck-law, or apply laminar-flame-speed-library instead of a piecewise-linear polynomial function. See Laminar Flame Speed in the Fluent Theory Guide and Defining Physical Properties for the Unburnt Mixture for information about setting the other properties for the unburnt material.

  8. Set the values for the mean progress variable () and the mean mixture fraction () and its variance () at flow inlets and exits. (For problems that include a secondary stream, you will define boundary conditions for the mean secondary partial fraction and its variance as well.)

     Setup →   Boundary Conditions

    See Defining Non-Premixed Boundary Conditions for guidelines on setting mixture fraction and variance conditions, as well as thermal and velocity conditions at inlets.


    Important:  There are two ways to specify a premixed inlet boundary condition:

    1. If you defined the fuel composition in the Boundary tab to be the premixed inlet species, then you should set and in the boundary condition dialog boxes.

    2. If you set the fuel composition to pure fuel in the Boundary tab, you will need to set the correct equivalence ratio () and at your premixed inlet boundary condition.


    For example, if the premixed inlet of methane and air is at an equivalence ratio of 0.3, you can

    1. specify the mass fraction of the fuel composition of = 0.017, = 0.236, and = 0.747 in the Boundary tab and = 1 and = 0 in the boundary condition dialog box.

    2. specify the mass fraction of the fuel composition of = 1.0 in the Boundary tab and = 0.017 and = 0 in the boundary condition dialog box.

      Method (a) is preferred since it will have more points in the flame zone than method (b).

  9. Initialize the value of the progress variable.

     Solution →   Initialization → Patch...

    See Initializing the Progress Variable for details.

  10. Solve the problem and perform postprocessing.

    See Solving the Flow Problem for guidelines about setting solution parameters. (These guidelines are for non-premixed combustion calculations, but they are relevant for partially premixed as well.)


Release 18.2 - © ANSYS, Inc. All rights reserved.