21.2.1. Using the SOx Model

When the sulfur content in the fuel is low, concentrations that are generated in combustion generally have minimal influence on the predicted flow field, temperature, and major combustion product concentrations. The most efficient way to use the model is as a postprocessor to the main combustion calculation. However, if the sulfur content is high, then  formation should be coupled with the gas phase combustion process rather than treating it as a postprocessing step.

The procedure for enabling and setting up the model for a decoupled solution is as follows:

  1. Calculate your combustion problem using ANSYS Fluent.


    Important:  The premixed combustion model and the Flamelet generated manifold model are not compatible with the  model.


  2. Enable the  model, define the fuel streams, and set the appropriate parameters, as described in this section.

     Setup → Models → Species → SOx   Edit...

  3. Define the boundary conditions for and (and , , or if necessary) at flow inlets.

     Setup →   Boundary Conditions

  4. In the Equations Dialog Box, turn off the solution of all variables except species and (and , , or , based on your selections).

     Solution →   Controls → Equations...

  5. Perform calculations until convergence (that is, until the and —and , , or , if solved—species residuals are below ) to ensure that the and concentration fields are no longer evolving.

     Solution →   Run Calculation

  6. Review the mass fractions of and (and , , or ) by generating graphical plots or alphanumeric reports in the usual way.

  7. Save a new set of case and data files, if desired.

     File → Write → Case & Data...

21.2.1.1. Enabling the SOx Model

To model formation, enable the SOx Formation option in the SOx Model Dialog Box (Figure 21.6: The SOx Model Dialog Box).

 Setup → Models → Species → SOx   Edit...

Figure 21.6:  The SOx Model Dialog Box

The SOx Model Dialog Box

21.2.1.2. Defining the Fuel Streams

When modeling fuel formation, ANSYS Fluent allows you to define up to three separate fuel streams, and to select the fuel sources for each fuel stream.

You can define multiple fuel streams to include in your model with the following configurations:

  • Solid and liquid fuels (combusting particle and droplet) both contributing to fuel .

  • Two or three solid fuels with different -content and / production models (two or three combusting particles), for example coal blends, coal-biomass cofiring, and so on.

  • Two or three liquid fuels with different -content and / production models (two or three droplet or multicomponent particles).

  • Gas and solid (or droplet) fuel both contributing to fuel .

    In addition, you can model one solid fuel contributing to in the presence of another reacting solid particle not containing any , by specifying the active fuel source for formation. For this configuration, you will not need to define multiple fuel streams in your model.

You can define multiple fuel streams when you are modeling  formation, as shown in the following steps:

  1. Specify the Number of Fuel Streams in the Fuel Streams group box. You are allowed up to three separate fuel streams.

  2. Define the first fuel stream. 

    1. Select the fuel stream to be defined by using the arrow keys of the Fuel Stream ID field.

    2. Select the Fuel Type in the Fuel Stream Settings group box.

    3. If your Fuel Type is Liquid or Solid, select the S sources from the Fuel Sources list.

      • If the Fuel Type is Solid and you have defined multiple injections with different combusting particle materials in your reacting flow calculation, the available combusting particle materials will be listed in the Fuel Sources list. Select one or more materials from the list to be included as fuel sources in the SOx calculation. Your selection will be used to determine the char burnout rate and volatile release rate in Equation 14–124 and Equation 14–125 in the Theory Guide. Make sure to deselect all combusting particle materials that do not contribute to .

      • If the Fuel Type is Liquid and you have defined multiple injections with different droplet or multicomponent particle materials in your reacting flow calculation, the available materials will be listed in the Fuel Sources list. Select one or more materials from the list to be included as fuel sources in the SOx calculation. Your selection will be used to determine the fuel release rate in Equation 14–123 in the Theory Guide. Make sure to deselect all droplet and multicomponent materials that do not contribute to .

    4. If the Fuel Type in your model is Gas, select one or more materials from the Fuel Species list. You cannot select more than 5 fuel species for each fuel stream, and the total number of fuel species selected for all the fuel streams combined cannot exceed 10. Your selection will be used to determine the mean limiting reaction rate in Equation 14–122 in the Theory Guide.

    5. Specify the parameters for this particular fuel stream in the Fuel Stream Settings group box. See Defining the SOx Fuel Stream Settings for details.

  3. Repeat steps 2.(a)–2.(e) for each additional fuel stream.


Important:  Important considerations should be made when reading case and data files set up in a version of ANSYS Fluent 14.5 or earlier:

  • When reading a case and data file with multiple injection materials that was set up in a version of ANSYS Fluent previous to and including 14.5, ANSYS Fluent will initialize the injection material specific fuel S sources for the fuel model. ANSYS Fluent will perform a DPM iteration when the flow iterations are initiated.

  • When reading a case file that was set up in a version older than ANSYS Fluent 14.5 with multiple fuel streams defined for the SOx model, you must review the setup and select the S sources from the Fuel Sources list.


21.2.1.3. Defining the SOx Fuel Stream Settings

When using the model, you must set the parameters in the Fuel Stream Settings group box for each fuel stream specified in the Fuel Stream ID field.

To begin, specify the fuel type in the following manner:

  • To calculate  formation from a solid fuel, select Solid under Fuel Type.

  • To calculate  formation from a liquid fuel, select Liquid under Fuel Type.

  • To calculate  formation from a gaseous fuel, select Gas under Fuel Type.

Figure 21.7:  The SOx Model Dialog Box Displaying Liquid Fuel Parameters

The SOx Model Dialog Box Displaying Liquid Fuel Parameters

Note that you can use only one of the fuel types for a given fuel stream. The Gas option is available only when the Species Transport model is enabled (see Enabling Species Transport and Reactions and Choosing the Mixture Material).

21.2.1.3.1. Setting SOx Parameters for Gaseous and Liquid Fuel Types

If you have selected Gas or Liquid as the Fuel Type, you must specify the following:

  • Select the intermediate species (h2s, so2, or h2s/so2) in the S Intermediate drop-down list.

  • Set the correct mass fraction of sulfur in the fuel (kg sulfur per kg fuel) in the Fuel S Mass Fraction field.

  • Specify the overall fraction of the fuel , by mass, that will be converted to the intermediate species and/or product in the Conversion Fraction field. Therefore, any remaining will not contribute to  formation. This is based on the assumption that the remaining volatile will convert to gas phase sulfur. The Conversion Fraction for the S Intermediate has a default value of 1.

  • If you selected h2s/so2 as the intermediate, you must set the fraction of the converted fuel , by mass, that will become h2s under Partition Fractions. The fraction of fuel that will become will be calculated by the remainder.

    Note that setting a partition fraction of 0 for is equivalent to assuming that all fuel is converted to the final product .

21.2.1.3.2. Setting SOx Parameters for a Solid Fuel

For solid fuel, several inputs are required for the model.

Figure 21.8:  The SOx Model Dialog Box Displaying Solid Fuel Parameters

The SOx Model Dialog Box Displaying Solid Fuel Parameters

  • Select the intermediate species (h2s, so2, or h2s/so2) in the S Intermediate drop-down list.

  • Specify the mass fraction of sulfur in the volatiles in the Volatile S Mass Fraction field.

  • Specify the overall fraction of the volatile , by mass, that will be converted to the intermediate species and/or product in the Conversion Fraction field.

  • If you selected h2s/so2 as the volatile intermediate, you must specify the fraction of the converted volatile , by mass, that will become h2s under Partition Fractions. The fraction of volatile that will become will be calculated by the remainder.

  • Select the char conversion path from the Char S Conversion drop-down list as so2, h2s, or so2/h2s.

  • Specify the mass fraction of sulfur in the char in the Char S Mass Fraction field.

  • Specify the overall fraction of the char , by mass, that will be converted to the intermediate species and/or product in the Conversion Fraction field.

  • If you selected so2/h2s from the Char S Conversion drop-down list, you must specify the fraction of the converted char , by mass, that will become under Partition Fractions. The fraction of char that will become will be calculated by the remainder.

The following equations are used to determine the mass fraction of sulfur in the volatiles and char:

(21–8)

where

 
 

= rate of release of fuel sulfur in kg/s

 

= rate of release of volatiles (v) or char (c) in kg/s

 

= mass fraction of sulfur in volatiles or char

Let

 
 

= total sulfur mass fraction in daf coal (that is, from daf ultimate analysis)

 

= char sulfur as a fraction of total sulfur

 

= mass fraction of volatiles in daf coal

 

= mass fraction of char in daf coal

Then the following should hold:

(21–9)

(21–10)

(21–11)

(21–12)

(21–13)

21.2.1.4. Defining the SOx Formation Model Parameters

You can set the formation model parameters that apply to all of the fuel streams in the Formation Model Parameters group box:

  • You have the option of including as a product, and including and as intermediates by enabling the Include SO3 Product and the Include SH and SO Intermediates options, respectively. See Reaction Mechanisms for Sulfur Oxidation in the Theory Guide for further information.

  • Specify the method by which and will be calculated. The routines employ three methods for reduction calculations of :

    • You can select equilibrium, partial-equilibrium, or instantaneous in the [O] Model drop-down list.

    • You can select none, partial-equilibrium, or instantaneous in the [OH] Model drop-down list.


    Important:  To use the predicted and/or concentration, select instantaneous in the [O] Model or [OH] Model drop-down list.


21.2.1.5. Setting Turbulence Parameters

If you want to take into account turbulent fluctuations when you compute the specified formation, define the turbulence parameters in the Turbulence Interaction Mode group box.

Figure 21.9:  The SOx Model Dialog Box for a Gas Fuel Type with Turbulence

The SOx Model Dialog Box for a Gas Fuel Type with Turbulence

Select one of the options in the PDF Mode drop-down list:

  • Select temperature to take into account fluctuations of temperature.

  • Select temperature/species to take into account fluctuations of temperature and mass fraction of the species selected in the Species drop-down list (which appears when you select this option).

  • (non-premixed and partially premixed combustion calculations only) Select mixture fraction to take into account fluctuation in the mixture fraction(s).


Important:  When modeling the formation of other pollutants along with , you should compare the selections made in the PDF Mode drop-down lists in the Turbulence Interaction Mode tab of the NOx Model Dialog Box and the Turbulence Interaction Mode group boxes of the SOx Model and Soot Model dialog boxes. If mixture fraction is selected in any of these dialog boxes, then it must be selected in all of the others as well.


The mixture fraction option is available only if you are using either the non-premixed or partially premixed combustion model to model the reacting system. If you use the mixture fraction option, the instantaneous temperatures and species concentrations are taken from the PDF look-up table as a function of mixture fraction and enthalpy and the instantaneous rates are calculated at each cell. The PDF used for convoluting the instantaneous  rates is the same as the one used to compute the mean flow-field properties. For example, for single-mixture fraction models the beta PDF is used, and for two-mixture fraction models, the beta or the double delta PDF can be used. The PDF for mixture fraction is calculated from the values of mean mixture fraction and variance at each cell, and the instantaneous rates are convoluted with the mixture fraction PDF to yield the mean rates in turbulent flow.

If you selected temperature or temperature/species for the PDF Mode, you should define the following parameters in the Turbulence Interaction Mode group box:

PDF Type

allows you to specify the shape of the PDF, which is then integrated to obtain mean rates for the temperature and (if you selected temperature/species for the PDF Mode) the species. If you select beta, the PDF will be modeled using Equation 14–108 in the Theory Guide. If you select gaussian, the PDF will be modeled using Equation 14–111 in the Theory Guide.

PDF Points

allows you to specify the number of points used to integrate the beta or Gaussian function in Equation 14–105 or Equation 14–106 in the Theory Guide on a histogram basis. The default value of 10 is a minimum value. It is recommended that you run the calculation with this minimum value to convergence, and then keep increasing the value (for example, 20–25) until the pollutants of interest stop changing. Increasing this value may improve accuracy, but will also increase the computation time.

Temperature Variance

allows you to specify the form of transport equation that is solved to calculate the temperature variance. The default selection is algebraic, which is an approximate form of the transport equation (see Equation 14–114 in the Theory Guide). You have the option of selecting transported to instead solve Equation 14–113 in the Theory Guide. Though the transported form is more exact, it is also more expensive computationally.

Tmax Option

provides various options for determining the maximum limit of the temperature used for the integration of the PDF (see Equation 8–43 in the Fluent Theory Guide) to calculate mean rates for turbulent fluctuations of SOx:

  • The default selection is global-tmax, which sets the limit as the maximum temperature in the flow field.

  • You can select local-tmax if you would rather obtain cell-based maximum temperature limits by multiplying the local cell mean temperature by the value entered in Tmax Factor.

  • You can select specified-tmax to set the limit for each cell to be the value entered in Tmax.

  • If you have selected a user-defined function from the SOx Rate drop-down menu in the User-Defined Functions group box, then you can select user-defined so that the limit is specified by a user-defined function. See the Fluent Customization Manual for details about user-defined functions.

Species

only appears if you have selected temperature/species for the PDF Mode. Your selection in this drop-down menu determines which species’ mass fraction is included in the  formation calculations.


Important:  Note that the species variance will always be calculated using the algebraic form of the transport equation (Equation 14–114 in the Theory Guide).


21.2.1.6. Specifying a User-Defined Function for the SOx Rate

You can choose to specify a user-defined function for the rate of production. By default, the rate returned from the user-defined function is added to the rate returned from the standard production options. You also have the option of replacing ANSYS Fluent’s rate calculations with your own user-defined rate.

In addition to or instead of using the UDF to specify the  rate, you can use it to specify custom values for the maximum limit () that is used for the integration of the temperature PDF (when temperature is accounted for in the turbulence interaction modeling).

To use a UDF to add a rate to ANSYS Fluent’s  rate calculations, you must compile and load the desired function, and then select it from the SOx Rate drop-down list in the User-Defined Functions group box. After you have selected the UDF, you have the following options:

  • You can specify that your custom rate is added to the ANSYS Fluent  rate calculations, by retaining the default selection of Add to the Fluent Rate in the UDF Rate group box.

  • You can replace the ANSYS Fluent  rate calculations with your custom rate, by selecting Replace Fluent Rate in the UDF Rate group box.

  • You can specify custom values for , by selecting user-defined from the Tmax Option drop-down list in the Turbulence Interaction Mode group box.

See the Fluent Customization Manual for details about user-defined functions.

21.2.1.7. Defining Boundary Conditions for the SOx Model

At flow inlet boundaries, you must specify the Pollutant SO Mass Fraction, and if necessary, the Pollutant SH Mass Fraction, Pollutant H2S Mass Fraction, Pollutant SO3 Mass Fraction, and Pollutant SO2 Mass Fraction in the Species tab, as demonstrated in Figure 21.10: The Mass-Flow Inlet Dialog Box and the Species Tab.

 Setup →   Boundary Conditions

You can retain the default inlet values of zero for these quantities or you can enter nonzero numbers as appropriate for your combustion system.

Figure 21.10:  The Mass-Flow Inlet Dialog Box and the Species Tab

The Mass-Flow Inlet Dialog Box and the Species Tab


Release 18.2 - © ANSYS, Inc. All rights reserved.