ANSYS Fluent provides four segregated types of algorithms: SIMPLE, SIMPLEC, PISO, and (for time-dependent flows using the Non-Iterative Time Advancement option (NITA)) Fractional Step (FSM). These schemes are referred to as the pressure-based segregated algorithm. Steady-state calculations will generally use SIMPLE or SIMPLEC, while PISO is recommended for transient calculations. PISO may also be useful for steady-state and transient calculations on highly skewed meshes. In ANSYS Fluent, using the Coupled algorithm enables full pressure-velocity coupling, hence it is referred to as the pressure-based coupled algorithm.
Important: Pressure-velocity coupling is relevant only for the pressure-based solver.
In ANSYS Fluent, both the standard SIMPLE algorithm and the SIMPLEC (SIMPLE-Consistent) algorithm are available. SIMPLE is the default, but many problems will benefit from using SIMPLEC, particularly because of the increased under-relaxation that can be applied, as described below.
For relatively uncomplicated problems (laminar flows with no additional models enabled) in which convergence is limited by the pressure-velocity coupling, you can often obtain a converged solution more quickly using SIMPLEC. With SIMPLEC, the pressure-correction under-relaxation factor is generally set to 1.0, which aids in convergence speed-up. In some problems, however, increasing the pressure-correction under-relaxation to 1.0 can lead to instability due to high mesh skewness. For such cases, you will need to use one or more skewness correction schemes, use a slightly more conservative under-relaxation value (up to 0.7), or use the SIMPLE algorithm. For complicated flows involving turbulence and/or additional physical models, SIMPLEC will improve convergence only if it is being limited by the pressure-velocity coupling. Often it will be one of the additional modeling parameters that limits convergence; in this case, SIMPLE and SIMPLEC will give similar convergence rates.
The PISO algorithm (see PISO in the Theory Guide) with neighbor correction is highly recommended for all transient flow calculations, especially when you want to use a large time step. (For problems that use the LES turbulence model, which usually requires small time steps, using PISO may result in an increased computational expense, so SIMPLE or SIMPLEC should be considered instead.) PISO can maintain a stable calculation with a larger time step and an under-relaxation factor of 1.0 for both momentum and pressure. For steady-state problems, PISO with neighbor correction does not provide any noticeable advantage over SIMPLE or SIMPLEC with optimal under-relaxation factors.
PISO with skewness correction is recommended for both steady-state and transient calculations on meshes with a high degree of distortion.
When you use PISO neighbor correction, under-relaxation factors of 1.0 or near 1.0 are recommended for all equations. If you use just the PISO skewness correction for highly-distorted meshes (without neighbor correction), set the under-relaxation factors for momentum and pressure so that they sum to 1 (for example, 0.3 for pressure and 0.7 for momentum). If you use both PISO methods, follow the under-relaxation recommendations for PISO neighbor correction, above.
For most problems, it is not necessary to disable the default coupling between neighbor and skewness corrections. For highly distorted meshes, however, disabling the default coupling between neighbor and skewness corrections is recommended.
The Fractional Step method (FSM), described in Fractional-Step Method (FSM) in the Theory Guide, is available when you choose to use the NITA scheme (that is, the Non-Iterative Time Advancement option in the Solution Methods task page). With the NITA scheme, the FSM is slightly less computationally expensive compared to the PISO algorithm. Whether you select FSM or PISO depends on the application. For some problems (for example, simulations that use VOF), FSM could be less stable than PISO.
In most cases, the default values for the solution methods are enough to set a robust convergence of the internal pressure correction sub-iterations due to skewness. Only very complex problems (for example, moving deforming meshes, sliding interfaces, the VOF model) could require a reduction of relaxation for pressure up to a value of 0.7 or 0.8.
Selecting Coupled from the Pressure-Velocity Coupling drop-down list indicates that you are using the pressure-based coupled algorithm, described in Coupled Algorithm in the Theory Guide. This solver offers some advantages over the pressure-based segregated algorithm. The pressure-based coupled algorithm obtains a more robust and efficient single phase implementation for steady-state flows. It is not available for cases using the Non-Iterative Time Advancement option (NITA).
Note: In some cases using porous jump boundary conditions, the Coupled scheme may suffer from convergence issues that do not respond to changes in the coupled solver settings. This behavior depends on the specific flow configuration and porous jump boundary condition values. If convergence instability is observed in cases using porous jump boundary conditions and the scheme, it is recommended that you change the pressure-velocity coupling to one of the segregated schemes.
You can specify the pressure-velocity coupling method in the Solution Methods Task Page (Figure 28.4: The Solution Methods Task Page for the Pressure-Based Segregated Algorithm).
Solution →
Methods
Choose SIMPLE, SIMPLEC, PISO, Fractional Step, or Coupled in the Pressure-Velocity Coupling drop-down list.
If you choose PISO, the task page will
expand to show the additional parameters for pressure-velocity coupling.
By default, the number of iterations for Skewness Correction and Neighbor Correction are set to 1. If you want to use only Skewness Correction, then set the number of iterations for Neighbor Correction to 0. Likewise, if you want to use only Neighbor Correction, then set the number of iterations
for Skewness Correction to 0. For most problems, you do not need to change the default iteration
values. By default, the Skewness-Neighbor Coupling option is enabled to allow for a more economical, but a less robust
variation of the PISO algorithm.
If you choose SIMPLEC under Pressure-Velocity
Coupling, you must also set the Skewness Correction, whose default value is 0.
If you choose Coupled, you will have to
specify the Courant number in the Solution
Controls task page, which is set at 200 by default. You will also specify the Explicit Relaxation
Factors for Momentum and Pressure, which are set at 0.75 by default. For more information about these options, refer to Pressure-Velocity Coupling and Steady-State Iterative Algorithm in the Theory Guide.
If high-order momentum discretization is used, you may need
to decrease the explicit relaxation to 0.5. For cases with very skewed meshes, the run can be stabilized by
further reduction of the explicit relaxation factor to 0.25. If ANSYS Fluent immediately diverges in the AMG
solver, then the CFL number is too high and should be reduced. Reducing
the CFL number below 10 is not recommended
since it would be better to use the segregated algorithm for the pressure-velocity
coupling.
In most transient cases, the CFL number should be set to with an explicit relaxation of 1.0.
If you choose Coupled and enable the Pseudo Transient option, you will set the Pseudo Transient Explicit Relaxation Factors in the Solution Controls task page, as described in Setting Pseudo Transient Explicit Relaxation Factors.