If you are using the Eulerian multiphase model (Setting Up the Eulerian Model), you have the option of including the Boiling Model (see Wall Boiling Models in the Theory Guide).
Note the following limitations:
This model is only available with the Eulerian multiphase model.
This model is only available with the Pressure-Based solver.
The required work flow when using the boiling model is as follows:
Open the Multiphase Model dialog box (Figure 24.59: The Boiling Model).
Setup →
Models →
Multiphase → Edit...
Enable Boiling Model under Eulerian Parameters.
Select RPI Boiling Model, Non-equilibrium Boiling, or Critical Heat Flux as the boiling model option. Information about the three options is available in RPI Model, Non-equilibrium Subcooled Boiling, and Critical Heat Flux in the Theory Guide.
Set the total Number of Eulerian Phases that are present in your case. This can consist of two phases: liquid
and vapor, which are directly involved in boiling mass transfer; or
it can include “non-boiling phases” or “species“.
If a system consists of three phases: liquid, vapor, and air, then
the Number of Eulerian Phases will be 3, where air is the non-boiling phase.
To include the liquid volume fraction effects, use the solve/set/multiphase-numeric/boiling-parameters/liquid-vof-factor text command. When this option is enabled, the heat transfer coefficients of boiling models will be multiplied by the local liquid volume fraction.
To include the thin film effects, use the solve/set/multiphase-numeric/boiling-parameters/thin-film text command. When enabled, this option will use Equation 17–431 in the Fluent Theory Guide in the calculation.
Make sure the energy option is enabled.
Note: The energy option will be automatically turned on when the boiling model is enabled.
Setup → Models → Energy
On
Enable Gravity and set the Operating Pressure in the Operating Conditions dialog box.
Important: Make sure gravity is included when the boiling model is used.
Choose one of the turbulence models that is available with the Eulerian multiphase model.
Setup →
Models →
Viscous → Edit...
Open the Create/Edit Materials dialog box and specify the material properties for the liquid, vapor, solid, and any other phases that may exist.
Setup →
Materials →
Fluid → Create/Edit...
Important: For the liquid and vapor phases, the Standard State Enthalpy must be specified, as it is used in the computation of the Latent Heat.
Open the Phases dialog box, in order to define the phases.
Setup → Models → Multiphase → Phases
Edit...
Define the liquid as the primary phase by selecting the phase from the Phases selection list that is labeled Primary Phase and clicking the button. Define the vapor as the secondary phase. In the Secondary Phase dialog box, the Diameter is set to boiling-dia by default, but you have the option of setting it up as a constant value or a user-defined function, as shown in Figure 24.60: The Secondary Phase Dialog Box.
Open the Phase Interaction dialog box.
Setup → Models → Multiphase → Phases
Edit... → Interaction...
In the Drag tab, you have a choice of ishii, universal-drag, schiller-naumann, symmetric, morsi-alexander, grace, tomiyama, or user-defined. See Specifying the Drag Function for definitions of the drag options For boiling flows, ishii is usually chosen.
In the Lift tab, select moraga, tomiyama, saffman-mei, legendre-magnaudet, or user-defined. For boiling flows, tomiyama is usually chosen.
In the Wall Lubrication tab, select antal-et-al, tomiyama-et-al, frank, hosokawa, or user-defined as described in Including the Wall Lubrication Force. For boiling flows, antal-et-al is typically chosen.
In the Turbulent Dispersion tab, select lopez-de-bertodano, simonin, burns-et-al, diffusion-in-vof, or user-defined as described in Including the Turbulent Dispersion Force. For boiling flows, lopez-de-bertodano is typically chosen.
In the Turbulent Interaction tab, select troshko-hassan, sato, or simonin-et-al as described in Including Turbulence Interaction Source Terms. For boiling flows, troshko-hassan is typically chosen.
In the Heat tab, select ranz-marshall, tomiyama, or user-defined. For boiling flows, ranz-marshall is usually chosen.
In the Surface Tension tab, select constant and enter the desired value.
In the Interfacial Area tab, you have four formulations available from which to select:
ia-symmetric (default) (see Equation 17–177 in the Theory Guide)
ia-particle (see Equation 17–176 in the Theory Guide)
ia-ishii (see Equation 17–178 in the Theory Guide). This option is only available with the RPI model.
user-defined (see Example 4- Custom Interfacial Area in the Fluent Customization Manual)
For boiling flows, ia-symmetric or ia-particle are usually chosen.
In the Mass tab, set the Number of Mass Transfer Mechanisms to 1 and make sure the transfer is always from the liquid to the vapor
phase. Select boiling under Mechanism. The Boiling Model dialog box will open (Figure 24.62: The Boiling Model Dialog Box), where you will set the boiling model
parameters and the quenching model corrections.
Specify the Interfacial Model Constants and the Saturation Temperature. The default values for the liquid and vapor interface transfer coefficients are 1.
If you use the polynomial, piecewise-polynomial, or piecewise-linear option for Saturation Temperature, the pressure-dependency must be specified in terms of absolute pressure.
If you selected the RPI Boiling Model in the Multiphase Model dialog box, then you will not need to specify the Vapor-Interface Transfer Coeff., since the vapor phase temperature is fixed to the saturation temperature.
Under the Boiling Model Parameters, select the Bubble Departure Diameter that best describes your model. Five options exist: tolubinski-kostanchuk (the default setting), unal, kocamustafaogullari-ishii, constant, and user-defined. The tolubinski-kostanchuk formulation is described in Equation 17–419 in the Theory Guide, the unal formulation is described in Equation 17–421 in the Theory Guide and the kocamustafaogullari-Ishii formulation is described in Equation 17–417 in the Theory Guide.
Specify the Frequency of Bubble Departure. You can choose the cole option (which is the default), or enter a constant value. The cole formulation is described in Equation 17–415 in the Theory Guide.
Specify the Nucleation Site Density. You can choose between lemmert-chawla (which is the default), kocamustafaogullari-ishii. and user-defined. This quantity is usually represented by a correlation based on the wall superheat, described in Equation 17–416 in the Theory Guide.
Note: It is recommended that when using the kocamustafaogullari-ishii option, it should be used for both the Bubble Departure Diameter and Nucleation Site Density.
Specify the Area Influence Coeff. The area of influence is based on the bubble departure diameter and the nucleate site density, as defined in Equation 17–412 in the Theory Guide. You have a choice of three options when modeling the area of influence coefficient: delvalle-kenning (which is the default and defined in Equation 17–413 in the Theory Guide, constant, and user-defined.
The Quenching Correction Model addresses the quenching term in the wall heat flux partition (described
in Wall Heat Flux Partition in the Theory
Guide). The quenching term in the wall heat flux partition
models the cyclic averaged transient energy transfer related to liquid
filling the wall vicinity after the bubble detachment with a period and it is expressed as:
(24–15) |
where is the liquid heat conductivity,
is the periodic time, and
is
the liquid phase diffusivity. The Bubble Waiting Time Coefficient,
, is a coefficient introduced to correct
the waiting time between departures of consecutive bubbles. The default
value is 1, however you can modify this value as needed, but it can
only be specified as a constant.
From Equation 24–15, you can see that the quenching model is
strongly dependent on , which results in grid-dependent solutions. To remedy this, two
approaches have been adopted in ANSYS Fluent: Fixed Yplus Value and Fixed Liquid Temperature.
Enable the Correction Model if you want to achieve a certain level of gird-independence in your solution. If this option is disabled, Equation 24–15 calculates the quench flux term without corrections.
Select Fixed Yplus Value if you
want to use the logarithmic form of the wall functions to estimate
the liquid temperature at a fixed Yplus value of 250, as proposed by Egorov and Mentor [27], instead of using the liquid temperature
values in the near-wall cells. Enter the Minimum Reference
Temperature, which limits the lowest value of the liquid
temperature. It should not be lower than the liquid inlet temperature.
Specify a Yplus Value. It is set to 250 by default.
If you select Fixed Liquid Temperature, you can choose from standard, constant, or user-defined for the Liquid Reference Temperature. You will also need to enter the Minimum Reference Temperature. The liquid temperature used to compute the quenching flux should usually be between the inlet liquid temperature and the saturation temperature.
Note: To learn how to hook boiling parameter user-defined functions,
refer to DEFINE_BOILING_PROPERTY in the Fluent Customization Manual.
Set up the conditions at inlets, outlets, and thermal conditions for walls.
Setup →
Boundary Conditions
For the quenching wall heat flux, Koncar et al. [54] have suggested that in order to avoid grid dependence when calculating the quenching heat transfer, a factor that relates the temperature at a fixed normalized distance (y+ = 250) to the temperature at the near wall cell must be applied. Contact a technical support engineer for more information.
The wall boiling models are compatible with three different wall boundaries: isothermal wall, specified heat flux, and specified heat transfer coefficient (coupled wall boundary).
Note: The boiling models do not apply to thin walls.
Choose Coupled as the pressure-velocity coupling scheme.
Solution →
Methods
Note: Although Phase Coupled SIMPLE is also available, it is generally less robust and is not recommended for use in steady cases involving boiling or mass transfer.
The following solution strategies are recommended for boiling model simulations:
Solution →
Controls
Courant Number: use a value between 1 and 20 is recommended. As a first try, use a value of 10.
Explicit Relaxation Factors: use the default values of 1 for Momentum and Pressure.
Vaporization Mass: use an under-relaxation factor between 0.5 and 1. As a first try, use a value of 1.
Volume Fraction: use an under-relaxation factor between 0.3 and 0.5.
Turbulent Kinetic Energy: use an under-relaxation factor between 0.3 and 0.8.
Turbulent Viscosity: use an under-relaxation factor between 0.5 and 1.0.
Energy: use an under-relaxation factor between 0.5 and 0.8.