24.7.5. VOF Model

Several recommendations for improving the accuracy and convergence of the VOF solution are presented here.

24.7.5.1. Setting the Reference Pressure Location

The site of the reference pressure can be moved to a location that will result in less round-off in the pressure calculation. By default, the reference pressure location is the center of the cell at or closest to the point (0,0,0). You can move this location by specifying a new Reference Pressure Location in the Operating Conditions Dialog Box.

 Setup →   Cell Zone Conditions → Operating Conditions...

The position that you choose should be in a region that will always contain the least dense of the fluids (for example, the gas phase, if you have a gas phase and one or more liquid phases). This is because variations in the static pressure are larger in a more dense fluid than in a less dense fluid, given the same velocity distribution. If the zero of the relative pressure field is in a region where the pressure variations are small, less round-off will occur than if the variations occur in a field of large nonzero values. Thus in systems containing air and water, for example, it is important that the reference pressure location be in the portion of the domain filled with air rather than that filled with water.

24.7.5.2. Pressure Interpolation Scheme

For all VOF calculations, you should use the body-force-weighted pressure interpolation scheme or the PRESTO! scheme.

 Solution →   Controls

24.7.5.3. Discretization Scheme Selection

The availability of discretization schemes for volume fraction is summarized in Spatial Discretization Schemes for Volume Fraction.

If you are modeling a sharp interface regime on meshes that have high aspect ratio cells, large jumps in cell size, or high skewness, interface capturing schemes such as Compressive and CICSAM will not produce very sharp results. For such cases, you should use the Geo-Reconstruct scheme.

For meshes of good quality, it is recommended that you use the Compressive scheme, which is available in both explicit and implicit formulations and is applicable to both sharp and dispersed flow regimes. The Compressive scheme also provides better accuracy compared with CICSAM and Modified HRIC for most cases. When used with the implicit formulation and the second order time scheme, the Compressive scheme produces quite a sharp interface.

When using the Compressive spatial discretization scheme, it is recommended that you use step-wise sharpening after the flow transitions from the diffused zone to the sharpening zone. In other words, you would want to transition from first order to second order, followed by a transition from second order to compressive. You would want to take this approach if the flow has a smooth transition from a sharp interfacial zone to a diffused interfacial zone. However, if the flow has a nonuniform transition from a diffused interfacial zone to a sharp interfacial zone, this might create unphysical sharpening of the interface if not handled properly, especially for transient cases. For example, transitioning from a slope limiter of 2 (compressive) to a slope limiter of 0 or 1 (first order or second order) might be acceptable, but a first order to compressive transition might create unphysical sharpening of the interface.

If you are solving a problem with the evaporation-condensation mass transfer mechanism enabled (Including Mass Transfer Effects) it is recommended that you use one of the diffusive interface capturing schemes such as QUICK, HRIC, or Phase Localized Compressive (Discretizing Using the Phase Localized Compressive Scheme).


Important:  The BGM scheme produces a sharp interface, which may result in poor convergence in some cases. In such situations, we recommend you use a low value for the VOF under-relaxation. In addition, you can start with the Compressive or Modified HRIC scheme and then switch to the BGM scheme.


24.7.5.4. High-Order Rhie-Chow Face Flux Interpolation

In VOF modeling, using a high-order discretization scheme for the momentum transport equations may reduce the stability of the solution compared to cases using first-order discretization. In such situations, there are a couple of recommendations:

  1. Use a low-order variant of the Rhie-Chow face flux interpolation. This is enabled using the following text command:

    solve → set → numerics

    You will be asked

     disable high order Rhie-Chow flux? [no]
    

    to which you will respond yes.

  2. Use a hybrid treatment of high-order Rhie-Chow face flux interpolation. This is enabled using the following text command:

    solve → set → vof-numerics

    You will be asked

     Use hybrid treatment for high order Rhie-Chow flux?  [no]
    

    to which you will respond yes.

    Hybrid treatment allows you to use a high-order variant of the Rhie-Chow face flux interpolation everywhere inside the domain, except in the vicinity of the interface where a low-order variant is used for the interpolation of the face flux. This treatment could be helpful to get better convergence without compromising much of the accuracy.

24.7.5.5. Treatment of Unsteady Terms in Rhie-Chow Face Flux Interpolation

For cases using Moving Mesh/Dynamic Mesh/Multiple Reference Frame models, ANSYS Fluent does not consider the unsteady terms for Rhie-Chow face flux interpolation by default. Accounting for the unsteady terms helps to achieve better solution stability, especially when using a lower time step size with the PRESTO scheme.

To enable forced treatment of unsteady terms in Rhie-Chow face flux interpolation, use the following text command:

solve → set → vof-numerics

You will be asked

 Use forced treatment of unsteady terms in Rhie-Chow flux? [no]

to which you will respond yes.

24.7.5.6. Using Unstructured Variant of PRESTO Pressure Scheme

For hexahedral and quadrilateral meshes, ANSYS Fluent uses the structured variant of the PRESTO scheme by default. For certain cases with non-conformal grid interfaces, the structured variant produces unexpected behavior at the intersection of the fluid-fluid and non-conformal grid interfaces. For these cases, using an unstructured variant of PRESTO provides better solution stability and avoids unexpectedly high velocities in the vicinity of the non-conformal grid interfaces.

To enable the unstructured variant of the PRESTO scheme, use the following text command:

solve → set → vof-numerics

You will be asked

 Use unstructured variant of PRESTO pressure scheme? [no]

to which you will respond yes.


Note:  The unstructured variant of PRESTO is automatically enabled for cases involving an unstructured mesh and this option is redundant in its usage.


24.7.5.7. Pressure-Velocity Coupling and Under-Relaxation for the Time-dependent Formulations

Another change that you should make to the solver settings is in the pressure-velocity coupling scheme and under-relaxation factors that you use. The PISO scheme is recommended for transient calculations in general. Using PISO allows for increased values on all under-relaxation factors, without a loss of solution stability. You can generally increase the under-relaxation factors for all variables to 1 and expect stability and a rapid rate of convergence (in the form of few iterations required per time step). For calculations on tetrahedral or triangular meshes, an under-relaxation factor of 0.7–0.8 for pressure is recommended for improved stability with the PISO scheme.

 Solution →   Controls

As with any ANSYS Fluent simulation, the under-relaxation factors will need to be decreased if the solution exhibits unstable, divergent behavior with the under-relaxation factors set to 1. Reducing the time step is another way to improve the stability.

24.7.5.8. Under-Relaxation for the Steady-State Formulation

If you are using the steady-state implicit VOF scheme, the under-relaxation factors for all variables should be set to values between 0.2 and 0.5 for improved stability.


Release 18.2 - © ANSYS, Inc. All rights reserved.