23.6.1. Performing Trajectory Calculations

The trajectories of your discrete phase injections are computed when you display the trajectories using graphics or when you perform solution iterations. That is, you can display trajectories without impacting the continuous phase, or you can include their effect on the continuum (termed a coupled calculation). In turbulent flows, trajectories can be based on mean (time-averaged) continuous phase velocities or they can be impacted by instantaneous velocity fluctuations in the fluid. This section describes the procedures and commands you use to perform coupled or uncoupled trajectory calculations, with or without stochastic tracking or cloud tracking.

23.6.1.1. Uncoupled Calculations

For the uncoupled calculation, you will perform the following two steps:

  1. Solve the continuous phase flow field.

  2. Plot (and report) the particle trajectories for discrete phase injections of interest.

In the uncoupled approach, this two-step procedure completes the modeling effort, as illustrated in Figure 23.34: Uncoupled Discrete Phase Calculations. The particle trajectories are computed as they are displayed, based on a fixed continuous-phase flow field. Graphical and reporting options are detailed in Postprocessing for the Discrete Phase.

Figure 23.34:  Uncoupled Discrete Phase Calculations

Uncoupled Discrete Phase Calculations

This procedure is adequate when the discrete phase is present at a low mass and momentum loading, in which case the continuous phase is not impacted by the presence of the discrete phase.

23.6.1.2. Coupled Calculations

In a coupled two-phase simulation, ANSYS Fluent modifies the two-step procedure above as follows:

  1. Solve the continuous phase flow field (prior to introduction of the discrete phase).

  2. Introduce the discrete phase by calculating the particle trajectories for each discrete phase injection.

  3. Recalculate the continuous phase flow, using the interphase exchange of momentum, heat, and mass determined during the previous particle calculation.

  4. Recalculate the discrete phase trajectories in the modified continuous phase flow field.

  5. Repeat the previous two steps until a converged solution is achieved in which both the continuous phase flow field and the discrete phase particle trajectories are unchanged with each additional calculation.

This coupled calculation procedure is illustrated in Figure 23.35: Coupled Discrete Phase Calculations. When your ANSYS Fluent model includes a high mass and/or momentum loading in the discrete phase, the coupled procedure must be followed in order to include the important impact of the discrete phase on the continuous phase flow field.

Figure 23.35:  Coupled Discrete Phase Calculations

Coupled Discrete Phase Calculations


Important:  When you perform coupled calculations, all defined discrete phase injections will be computed. You cannot calculate a subset of the injections you have defined. If there are massless particle injections defined, these will have no effect in the coupled calculation.


23.6.1.2.1. Procedures for a Coupled Two-Phase Flow

If your ANSYS Fluent model includes prediction of a coupled two-phase flow, you should begin with a partially (or fully) converged continuous-phase flow field. You will then create your injection(s) and set up the coupled calculation.

For each discrete-phase iteration, ANSYS Fluent computes the particle/droplet trajectories and updates the interphase exchange of momentum, heat, and mass in each control volume. These interphase exchange terms then impact the continuous phase when the continuous phase iteration is performed. During the coupled calculation, ANSYS Fluent will perform the discrete phase iteration at specified intervals during the continuous-phase calculation. The coupled calculation continues until the continuous phase flow field no longer changes with further calculations (that is, all convergence criteria are satisfied). When convergence is reached, the discrete phase trajectories no longer change either, since changes in the discrete phase trajectories would result in changes in the continuous phase flow field.

The steps for setting up the coupled calculation are as follows:

  1. Solve the continuous phase flow field.

  2. In the Discrete Phase Model Dialog Box (Figure 23.1: The Discrete Phase Model Dialog Box and the Tracking Parameters), enable the Interaction with Continuous Phase option.

  3. Set the frequency with which the particle trajectory calculations are introduced in the DPM Iteration Interval field. If you set this parameter to 5, for example, a discrete phase iteration will be performed every fifth continuous phase iteration. The optimum number of iterations between trajectory calculations depends upon the physics of your ANSYS Fluent model.


    Important:  Note that if you set this parameter to 0, ANSYS Fluent will not perform any discrete phase iterations.


During the coupled calculation (which you initiate using the Run Calculation Task Page in the usual manner) you will see the following information in the ANSYS Fluent console as the continuous and discrete phase iterations are performed:

iter   continuity   x-velocity   y-velocity       k         epsilon       energy    time/it
 314   2.5249e-01   2.8657e-01   1.0533e+00   7.6227e-02   2.9771e-02   9.8181e-03   :00:05
 315   2.7955e-01   2.5867e-01   9.2736e-01   6.4516e-02   2.6545e-02   4.2314e-03   :00:03
  
  DPM  Iteration  ....
  number  tracked=  9,  number  escaped=  1,  aborted=  0,  trapped=  0,  evaporated  =  8,i  
Done.
 316   1.9206e-01   1.1860e-01   6.9573e-01   5.2692e-02   2.3997e-02   2.4532e-03   :00:02
 317   2.0729e-01   3.2982e-02   8.3036e-01   4.1649e-02   2.2111e-02   2.5369e-01   :00:01
 318   3.2820e-01   5.5508e-02   6.0900e-01   5.9018e-02   2.6619e-02   4.0394e-02   :00:00  

Note that you can perform a discrete phase calculation at any time by using the solve/dpm-update text command.

23.6.1.2.2. Stochastic Tracking in Coupled Calculations

If you include the stochastic prediction of turbulent dispersion in the coupled two-phase flow calculations, the number of stochastic tries applied each time the discrete phase trajectories are introduced during coupled calculations will be equal to the Number of Tries specified in the Set Injection Properties Dialog Box. For transient particle tracking, the number of tries is set to 1. Input of this parameter is described in Stochastic Tracking. An input of requests stochastic trajectory calculations for each particle in the injection. When the number of stochastic tracks included is small, you may find that the ensemble average of the trajectories is quite different each time the trajectories are computed. These differences may, in turn, impact the convergence of your coupled solution. For good convergence of a coupled solution, a statistical independent distribution of tracks can be achieved with an adequate number of stochastic tracks and/or a sufficient number of different starting locations of the tracks.

23.6.1.2.3. Under-Relaxation of the Interphase Exchange Terms

When you are coupling the discrete and continuous phases using the calculation procedures noted above, ANSYS Fluent applies under-relaxation to the momentum, heat, and mass transfer terms. This under-relaxation serves to increase the stability of the coupled calculation procedure by letting the impact of the discrete phase change only gradually:

(23–13)

where is the exchange term, is the previous value, is the newly computed value, and is the particle/droplet under-relaxation factor. For , ANSYS Fluent uses a default value of 0.5 for all types of analysis except transient flows with unsteady particle tracking, in which case the default value of 0.9 is used. You can modify by changing the value in the Discrete Phase Sources field under Under-Relaxation Factors in the Solution Controls task page. You may need to decrease in order to improve the stability of coupled discrete phase calculations.

Figure 23.36: Effect of Number of Source Term Updates on Source Term Applied to Flow Equations shows how the source term, , when applied to the flow equations, changes with the number of updates for varying under-relaxation factors. In Figure 23.36: Effect of Number of Source Term Updates on Source Term Applied to Flow Equations, is the final source term for which a value is reached after a certain number of updates and is the initial source term at the start of the computation. The value of is typically zero at the beginning of the calculation.

Figure 23.36:  Effect of Number of Source Term Updates on Source Term Applied to Flow Equations

Effect of Number of Source Term Updates on Source Term Applied to Flow Equations

In a continuous flow simulation, with continuous DPM tracking, suppose that the DPM under-relaxation factor is chosen to be 0.5, with 20 continuous phase iterations per DPM iteration. From Figure 23.36: Effect of Number of Source Term Updates on Source Term Applied to Flow Equations, we see that approximately 10 source term updates are required for the DPM sources to reach their final values. Therefore, in this example, at least 200 continuous phase iterations are required after any change to the DPM sources (for example, a new injection or a changed DPM mass flow rate), to ensure that the change has taken effect.


Release 18.2 - © ANSYS, Inc. All rights reserved.