6.3.6. Mass-Flow Outlet Boundary Conditions

Mass-flow outlet boundaries can be used in ANSYS Fluent to pump flow out of the domain at a prescribed mass flow rate or mass flux distribution. A mass-flow outlet is often used when it is more important to match a prescribed mass flow rate than to match the static pressure of the outflow stream.

6.3.6.1. Limitations

Mass-flow outlet boundaries have the following limitations:

  • It is supported with single-phase flow only, and so is not supported with the VOF, mixture, and Eulerian multiphase models in the pressure-based solver.

  • It is not supported with the Wet Steam model in the density-based solver.

6.3.6.2. Inputs at Mass-Flow Outlet Boundaries

6.3.6.2.1. Summary

You will enter the following information for a mass-flow outlet boundary:

  • mass flow rate, mass flux, mass flux with average mass flux, or exit corrected mass flow rate with reference temperature and gauge pressure

  • flow direction

  • radiation parameters (for calculations using the P-1, DTRM, DO, surface-to-surface, or MC models)

  • discrete phase boundary conditions (for discrete phase calculations)

All values are entered in the Mass-Flow Outlet Dialog Box (Figure 6.24: The Mass-Flow Outlet Dialog Box), which is opened from the Boundary Conditions task page (as described in Setting Cell Zone and Boundary Conditions).

Figure 6.24:  The Mass-Flow Outlet Dialog Box

The Mass-Flow Outlet Dialog Box

6.3.6.2.2. Selecting the Reference Frame

Mass-flow outlets only support the Relative to Adjacent Cell Zone specification for the Reference Frame.

6.3.6.2.3. Defining the Mass Flow Rate or Mass Flux

You can specify the mass flow rate through the outlet zone and have ANSYS Fluent convert this value to mass flux, or specify the mass flux directly. For cases where the mass flux varies across the boundary, you can specify an average mass flux. For compressible problems, you can specify that the mass flow rate is adjusted to total conditions at the outlet, thus maintaining a constant exit corrected mass flow rate.

You can define the mass flow or mass flux rate using a profile or a user-defined function (UDF). For an example of a mass-flow outlet UDF, see DEFINE_PROFILE in the Fluent Customization Manual.


Important:  The hooked UDF or transient profile can only be used to provide time-varying specification of mass flow or mass flux rate. Therefore, the transient solver must be used to run the simulation. Note that the variation of profile with position in space is not applicable with this hookup.


The inputs for mass flow rate or flux are as follows:

  1. Make a selection in the Mass Flow Specification Method drop-down list to specify whether you will define a Mass Flow Rate, Mass Flux, Mass Flux with Average Mass Flux, or (if the density of the material is defined either as an ideal gas or using a real gas model) Exit Corrected Mass Flow Rate.

  2. If you selected Mass Flow Rate (the default), enter the prescribed Mass Flow Rate when constant is selected from the drop-down list. Otherwise, select your hooked user-defined function (UDF) or transient profile.

  3. If you selected Mass Flux, enter the prescribed Mass Flux (or select your hooked UDF or profile).

  4. If you selected Mass Flux with Average Mass Flux, enter the prescribed Mass Flux (or select your hooked UDF or profile) and Average Mass Flux.

    Note that if you specify a mass flux profile such that the average mass flux integrated over the zone area is 4.7, but you actually want to have a total mass flux of 5, you can keep the profile unchanged, and specify an average mass flux of 5. ANSYS Fluent will maintain the profile shape but adjust the values so that the resulting mass flux across the boundary is 5.

  5. If you selected Exit Corrected Mass Flow Rate, enter the prescribed Exit Corrected Mass Flow Rate (or select your hooked UDF or profile); this corresponds to in Equation 6–88. Then enter the ECMF Reference Temperature () and the ECMF Reference Gauge Pressure (). For complete details about this method, see Exit Corrected Mass Flow Rate.


Important:  Note that for axisymmetric problems:

  • If you provide a mass flow rate, you must specify the flow rate through the entire (-radian) domain, not through a 1-radian slice.

  • If you provide a mass flux rate, you must specify the flux through a 1-radian slice of the domain.


6.3.6.2.4. Defining the Flow Direction

You can define the flow direction at a mass-flow outlet explicitly, or you can define the flow to be leaving normal to the boundary.

The procedure for defining the flow direction is as follows, referring to Figure 6.24: The Mass-Flow Outlet Dialog Box:

  1. Specify the flow direction by selecting Direction Vector or Outward Normals in the Direction Specification Method drop-down list.

  2. If you selected Direction Vector and your geometry is 2D, go to the next step. If your geometry is 3D, choose Cartesian (X, Y, Z), Cylindrical (Radial, Tangential, Axial), Local Cylindrical (Radial, Tangential, Axial), or Local Cylindrical Swirl in the Coordinate System drop-down list. See Defining the Flow Direction for information about Cartesian, cylindrical, local cylindrical, and local cylindrical swirl coordinate systems.

  3. If you selected Direction Vector, set the vector components as follows:

    • If your geometry is 2D non-axisymmetric, or you chose to use a 3D Cartesian coordinate system, enter appropriate values for the X-, Y-, and (in 3D) Z-Component of Flow Direction.

    • If your geometry is 2D axisymmetric, or you chose to use a 3D Cylindrical coordinate system, enter appropriate values for the Axial-, Radial-, and (if you are modeling swirl or using cylindrical coordinates) Tangential-Component of Flow Direction.

    • If you chose to use a 3D Local Cylindrical coordinate system, enter appropriate values for the Axial-, Radial-, and Tangential-Component of Flow Direction, and then specify the X, Y, and Z components of Axis Origin and the Axis Direction.

    • If you chose to use a 3D Local Cylindrical Swirl coordinate system, enter appropriate values for the Axial- and Radial-Component of Flow Direction in the axial and radial planes, and the Tangential-Velocity. Specify the X, Y, and Z components of the Axis Origin and the Axis Direction.


    Important:  Note that if you are modeling axisymmetric swirl, the flow direction will be normal to the boundary; that is, there will be no swirl component at the boundary for axisymmetric swirl.


  4. If Outward Normals is selected, then the mass flow boundary will be pumping flow out of the domain normal to boundary at the prescribed rate or flux. If the mass flow rate is specified, then by default, the fluxes on the boundary will be allowed to vary to preserve the flow profile out of the domain. At convergence, the total mass flow rate should match the specified value.


    Important:  Note that if constant mass flux is needed rather than the default variable fluxes to preserve the profiles, then you can do so via the text command define/boundary-conditions/bc-settings/mass-flow. Answer no when asked to preserve profile while flow leaves.



    Note:  The mass-flow outlet boundary condition is designed to be strictly used only when flow is leaving the domain; it should not be used for mixed flow conditions (where flow is flowing in and out) or when flow is changing directions.


6.3.6.2.5. Defining Radiation Parameters

If you are using the P-1, DTRM, DO, surface-to-surface, or MC models, you will set the Internal Emissivity and (optionally) External Black Body Temperature. See Defining Boundary Conditions for Radiation for details. (The Rosseland radiation model does not require any boundary condition inputs.)

6.3.6.2.6. Defining Discrete Phase Boundary Conditions

If you are modeling a discrete phase of particles, you can set the fate of particle trajectories at the mass-flow outlet. See Setting Boundary Conditions for the Discrete Phase for details.

6.3.6.3. Default Settings at Mass-Flow Outlet Boundaries

Default settings (in SI) for mass-flow outlet boundary conditions are as follows:

Mass Flow Rate 1
Direction Specification Method Outward Normals

6.3.6.4. Calculation Procedure at Mass-Flow Outlet Boundaries

For the Mass Flow Rate specification method, you specify the total mass flow rate, , for the outlet. For the Mass Flux or Mass Flux with Averaged Mass Flux specification methods, you specify the mass flux, (mass flow rate per unit area). If a total mass flow rate is specified, ANSYS Fluent converts it internally to a uniform mass flux by dividing the mass flow rate by the total outlet area:

(6–87)

If the direct mass flux specification option is used, the mass flux can be varied over the boundary by using profile files or user-defined functions. If the average mass flux is also specified, it is used to correct the specified mass flux profile, as described previously in this section.

Once the value of at a given face has been determined, the density, , at the face must be determined in order to find the normal velocity, .

Boundary velocities are scaled to achieve the specified value of mass flow rate or mass flux. When the mass-flow outlet is used with the profile preserving feature, a scaling factor of the specified mass flow rate over the computed mass flow rate at the boundary is used to scale the normal face velocities at the boundary. The other velocity components will be extrapolated from the interior. Flow variables such as pressure, temperature, species, or other scalar quantities will be also extrapolated from adjacent cell centers.

6.3.6.4.1. Exit Corrected Mass Flow Rate

The Exit Corrected Mass Flow Rate specification method adjusts the mass flow rate to the total conditions at the outlet, maintaining a constant exit corrected mass flow rate. This boundary option is mainly intended for turbomachinery applications. This method allows you to sweep through the complete machine operational range, including machine operating points from choked flow to stall conditions. When using the Exit Corrected Mass Flow Rate specification method, the boundary operates like a mass-flow outlet on the left side of the speedline curve away from the best efficiency point, and more like a pressure outlet boundary to the right of the best efficiency point all the way beyond the choke point. This method allows you to specify the equivalent mass flow, based on similar criteria, corrected to a specified reference temperature and pressure.

For compressible flows, the exit corrected mass flow rate () is calculated as:

(6–88)

where and are mass-averaged values of total pressure and temperature in the absolute frame at the outlet. and are the reference conditions, which are constants in the equation. It should be noted that the numerical behavior of the boundary condition is not affected by the choice of reference conditions; rather, the reference conditions simply provide a dimensional meaning to the otherwise non-dimensional mass flow rate. It is typical to specify these reference conditions to be the same as the inflow total pressure and temperature.

In order to maintain a constant exit corrected mass flow, you can observe that the resulting mass flow rate must be proportional to the exit total pressure and inversely proportional to the square root of the exit total temperature (or equivalently, inversely proportional to the stagnation speed of sound). This allows the boundary condition to adapt dynamically to varying operating conditions, while remaining stable as the flow develops from the initial guess.

Note that the Exit Corrected Mass Flow Rate specification method is only available for ideal gas and real gas materials.

You can obtain an initial exit corrected mass flow rate value () from a previously converged case that uses standard inlet and outlet boundaries (for example, a pressure inlet and a pressure outlet). Use the converged solution to obtain the mass-flow-averaged value of and at the outlet boundary, as well as the mass flow rate (). These values can then be applied to Equation 6–88 along with and (which are usually taken as the inflow total temperature and pressure). After you have calculated the exit corrected mass flow rate, you can adjust this value up or down in order to traverse the speed line from choke to stall.


Release 18.2 - © ANSYS, Inc. All rights reserved.