You can specify the discretization scheme and, for the pressure-based solver, the pressure interpolation scheme in the Solution Methods Task Page (Figure 28.4: The Solution Methods Task Page for the Pressure-Based Segregated Algorithm).
Solution →
Methods
For each scalar equation listed under Spatial Discretization (Momentum, Energy, Turbulent Kinetic Energy, and so on, for the pressure-based solver or Turbulent Kinetic Energy, Turbulent Dissipation Rate, and so on, for the density-based solver) you can choose First Order Upwind, Second Order Upwind, Power Law, QUICK, Third-Order MUSCL, or (for Momentum when you are using the LES, DES, SAS, SDES, or SBES turbulence model) Bounded Central Differencing (the default) or Central Differencing in the adjacent drop-down list. For the density-based solver, you can choose either First Order Upwind, Second Order Upwind, or Third-Order MUSCL for the Flow equations (which include momentum and energy). Note that the task page shown in Figure 28.4: The Solution Methods Task Page for the Pressure-Based Segregated Algorithm is for the pressure-based solver.
If you are using the pressure-based solver, select the pressure interpolation scheme under Spatial Discretization, in the drop-down list next to Pressure. You can choose Standard, PRESTO!, Linear, Second Order, or Body Force Weighted.
Important: The low-order formulation of PRESTO! can be applied by limiting the high-order terms for the PRESTO! scheme. This is done using the following text command:
solve → set →
numerics
When asked limit high-order terms for PRESTO! pressure scheme?,
enter yes.
This modification can be used to stabilize the solution process when the pressure-based coupled algorithm is used and when the original PRESTO! scheme either fails to converge or produces unphysical oscillations (wiggles) in the pressure field.
If you are using the pressure-based solver and your flow is compressible (that is, you are using the ideal gas law for density), select the density interpolation scheme under Spatial Discretization, in the drop-down list next to Density. You can choose First Order Upwind, Second Order Upwind, QUICK or Third-Order MUSCL. (Note that Density will not appear for incompressible flows.)
If you enable the VOF model while using the pressure-based solver, the volume fraction interpolation schemes that are available are Geo-Reconstruct, CICSAM, Modified HRIC, and QUICK.
If your case involves species transport, you can set the scheme for the individual species as First Order Upwind, Second Order Upwind, Power Law, QUICK, or Third-Order MUSCL. However, if you want all your species to use the same discretization scheme, then rather than setting each one individually, simply enable the Set All Species Discretizations Together option. Notice that you will no longer see your list of individual species, instead a Species field will appear with the scheme of your choice.
If you change the settings for the Spatial Discretization, but you then want to return to ANSYS Fluent’s default settings, you can click the button.
Important: If your mesh topology has step-wise prism mesh near the walls, do not use node-based gradients with MUSCL.